CFD Online Logo CFD Online URL
Home > Forums > ANSYS Meshing & Geometry

[ICEM] triangle 86218 297 88224 seems to be in the wrong family

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By PSYMN

LinkBack Thread Tools Display Modes
Old   November 4, 2011, 01:25
Default triangle 86218 297 88224 seems to be in the wrong family
Join Date: Apr 2009
Location: Pune
Posts: 37
Rep Power: 10
Sushilkumar is on a distinguished road
What this error indicates..?

I want to create the prism layers, but it is not generating. The log file shows this message frequently.
Sushilkumar is offline   Reply With Quote

Old   November 4, 2011, 22:10
Retired from CFD Online
PSYMN's Avatar
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,665
Blog Entries: 1
Rep Power: 39
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
The shell elements inherit the part name of the surface they are generated on. This is actually done by ray tracing from the centroid of the shell in a normal direction. Sometimes this hits the wrong part and you can find some shells (usually near the edge of a surface) that are in a different part. Sometimes I will get this if I have overlapping surfaces in different parts; some shells will be in one part and adjacent interspersed shells will be in another depending on which surface the ray hit first.

When Prism runs, it extrudes shells based on their Part name. If you pick a part that has various other shells scattered in it that are not being extruded, this is a lot harder on the prism algorithm. In some cases, the part your extruding is the one that is scattered (or perhaps there is just a single shell in that part surounded by shells in an un-prismed part). The prismed shells try to form columns of prisms while trying to connect to the surrounding parts... Often it can handle it and you just have some quality issues (pyramid elements fit to the side of the column, particularly the thinnest base elements, are not usually good quality), other times the quality is so bad that the process fails and you get this message.

There is a check for these isolated shells (I forget the exact name of it but it is mentioned in the prism prep section of the help), or you could do a quick visual inspection. Either way, if you find any shells in the wrong part, right click on the part they should be in (in the model tree) and add those to the correct part... then run prism.

Best regards,

Sushilkumar likes this.
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   November 8, 2011, 11:52
Join Date: Apr 2009
Location: Pune
Posts: 37
Rep Power: 10
Sushilkumar is on a distinguished road
Thanks Simon.
Sushilkumar is offline   Reply With Quote


Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
udf error srihari FLUENT 1 October 31, 2016 15:18

All times are GMT -4. The time now is 03:54.