# Negative Density problem in starcd

 Register Blogs Members List Search Today's Posts Mark Forums Read

 January 23, 2009, 12:37 Negative Density problem in starcd #1 Dinesh Guest   Posts: n/a hi all I am running transient analysis with pressure -pressure boundary condition. i have one pressure in and 4 outlets (i.e pressure- pressure boundary condition). At any time one outlet is pressure and the rest all are wall. the pressure outlet interchanges with respect to time. This can be compared with air Induction in IC engine i.e when intake valve is opened its pressure and when closed it changes to wall.The problem i am facing is that when the boundary changing from wall to pressure or vice versa i am getting Negative density at the boundary. Is the solver is unstable during the change of boundries. Is there any way to get rid of it. I am running in MARS mode for momentum and Temp. Could any one help in this regared.... I am using Starcd 3.26

 January 23, 2009, 14:10 Re: Negative Density problem in starcd #2 Balduin Bankerotti Guest   Posts: n/a try underrelaxation of piso: also piso node 20 0.15 0.8

 January 23, 2009, 15:49 Re: Negative Density problem in starcd #3 Koblax Guest   Posts: n/a - check .info file if the problem is temperature convergence: set residual tolerance for temperature and scalars to 1e-3 - save .pst every time step - post process density to see which cells are -ve - reduce the time step: if it still give -ve density: your mesh is no good.

 January 26, 2009, 13:23 Re: Negative Density problem in starcd #4 alex Guest   Posts: n/a and try UD at least initially....

 January 26, 2009, 13:53 Re: Negative Density problem in starcd #5 James Guest   Posts: n/a Had you considered driving the model with velocity/massflow boundaries? The level of pressure does not set the mass in/out of the domain it is the gradient, which you are not setting. Also instaneously changing the boundary type to wall will almost certainly cause problems. You are trying to stop any massflow from entering and leaving essentially instaneously, which will naturally cause a very large negative or positivepressure pulse. If you are driving this with the output of one of the 1D engine flow solvers then you will have a lot better luck driving it with a massflow condition (or possibly coupling it in).

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Karl CD-adapco 2 July 10, 2008 16:41 Wendy Tjia CD-adapco 6 November 26, 2004 11:45 Jane CD-adapco 4 March 9, 2004 22:01 Miriam CD-adapco 0 May 10, 2002 04:21 M. R. JAHANNAMA Main CFD Forum 8 September 29, 1999 23:59

All times are GMT -4. The time now is 16:50.