CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > CFX

Using PT Outlet Profile as Inlet BC

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   March 2, 2015, 15:53
Question Using PT Outlet Profile as Inlet BC
  #1
New Member
 
Brian
Join Date: Feb 2015
Posts: 15
Rep Power: 11
cbrian is on a distinguished road
Hello,
I have a total pressure outlet profile that I'd like to use as the inlet boundary condition for another case. The issue is that the meshes are completely different. Ideally I'd like to use a circumferentially-averaged PT profile as the inlet BC but it seems this isn't possible in CFX.
What is the best way of going about this?
Thanks for any help you can give me.
cbrian is offline   Reply With Quote

Old   March 2, 2015, 16:38
Default
  #2
Super Moderator
 
diamondx's Avatar
 
Ghazlani M. Ali
Join Date: May 2011
Location: Tokyo, Japan
Posts: 1,385
Blog Entries: 23
Rep Power: 29
diamondx will become famous soon enough
In CFD-post, you can export a boundary profile, then use it as inlet boundary profile in CFX. Basically you will use, the "file - > export" function in cfd-post, then "tools -> initialize profile data" in CFX. For a mass flow for examples, the variable is dependent on x,y,z. I SUPPOSE even if your mesh changes but its position did not change, it can work... Hope it can help
__________________
Regards,
New to ICEM CFD, try this document --> https://goo.gl/KAOIwm
Ali
diamondx is offline   Reply With Quote

Old   March 2, 2015, 16:43
Default
  #3
Senior Member
 
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33
Opaque will become famous soon enough
Complementing diamondx response, if your case is a turbo machine you can use TurboPost do compute the circumferentially averaged profile. Such profile is radial only now, correct ?

You can then export as diamondx explained your radial profile, and use it in CFX-Pre as usual.
Opaque is offline   Reply With Quote

Old   March 2, 2015, 16:47
Default
  #4
New Member
 
Brian
Join Date: Feb 2015
Posts: 15
Rep Power: 11
cbrian is on a distinguished road
Quote:
Originally Posted by diamondx View Post
In CFD-post, you can export a boundary profile, then use it as inlet boundary profile in CFX. Basically you will use, the "file - > export" function in cfd-post, then "tools -> initialize profile data" in CFX. For a mass flow for examples, the variable is dependent on x,y,z. I SUPPOSE even if your mesh changes but its position did not change, it can work... Hope it can help
Unfortunately both the mesh and the position changed. I've tried using the profile anyway, but CFX diverged pretty quickly.

Quote:
Originally Posted by Opaque View Post
Complementing diamondx response, if your case is a turbo machine you can use TurboPost do compute the circumferentially averaged profile. Such profile is radial only now, correct ?

You can then export as diamondx explained your radial profile, and use it in CFX-Pre as usual.
This is indeed a turbomachine, I'm trying to use the output from a centrifugal impeller case as the input to the diffuser. I'll try using TurboPost, I wasn't even aware it existed but it probably came with our CFX package.
cbrian is offline   Reply With Quote

Old   March 2, 2015, 18:25
Default
  #5
New Member
 
Brian
Join Date: Feb 2015
Posts: 15
Rep Power: 11
cbrian is on a distinguished road
Quote:
Originally Posted by Opaque View Post
Complementing diamondx response, if your case is a turbo machine you can use TurboPost do compute the circumferentially averaged profile. Such profile is radial only now, correct ?

You can then export as diamondx explained your radial profile, and use it in CFX-Pre as usual.
I am able to pull a radial profile using TurboPost by generating a Circumferential Turbo Chart with a streamwise location of 0.99. However, I need the profile to be averaged over the span, which I do not see a way to do. Is this possible?
cbrian is offline   Reply With Quote

Old   March 2, 2015, 18:41
Default
  #6
Senior Member
 
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33
Opaque will become famous soon enough
Not sure what your goal of using the profile of the outlet as the inlet profile for the next simulation is ? If you average the profile on both directions: circumferential and span, you may as well put a uniform value that ballpark the average you want. Then, there is no need for exporting/importing.

The idea of using profile from one simulation to another is to keep as much information as possible from the "real distribution upstream" instead of guessing a distribution downstream.
Opaque is offline   Reply With Quote

Old   March 3, 2015, 06:09
Default
  #7
Senior Member
 
Thomas MADELEINE
Join Date: Oct 2014
Posts: 126
Rep Power: 12
Thomas MADELEINE is on a distinguished road
Hi all,
just to add some little thing to the discussion
when you import a profile for a boundary it is read as a function (XxYxZ -> value) so it is interpolated betwen each point you give (your ancient mesh) and read to your new mesh

moreover if you know the change you have done in your geometry you can adjust your profile quite easily in the BC setup: just replace X,Y,Z by the value you want
or create new variable to match the old profile with the new BC, exemple: X0 = X*cos(theta) + Y*sin(theta)

I suppose it works the same in the Turbo module
Thomas MADELEINE is offline   Reply With Quote

Old   March 4, 2015, 14:02
Default
  #8
New Member
 
Brian
Join Date: Feb 2015
Posts: 15
Rep Power: 11
cbrian is on a distinguished road
Quote:
Originally Posted by Opaque View Post
Not sure what your goal of using the profile of the outlet as the inlet profile for the next simulation is ? If you average the profile on both directions: circumferential and span, you may as well put a uniform value that ballpark the average you want. Then, there is no need for exporting/importing.

The idea of using profile from one simulation to another is to keep as much information as possible from the "real distribution upstream" instead of guessing a distribution downstream.
I got a little confused in my description of what I was looking for - what I wanted was a spanwise profile of total pressure, averaged circumferentially.
For future reference of anyone who finds this thread: this was possible to do using the Hub to Shroud Turbo Chart using the streamwise location mode.
cbrian is offline   Reply With Quote

Old   March 4, 2015, 14:12
Default
  #9
New Member
 
Brian
Join Date: Feb 2015
Posts: 15
Rep Power: 11
cbrian is on a distinguished road
Quote:
Originally Posted by Thomas MADELEINE View Post
Hi all,
just to add some little thing to the discussion
when you import a profile for a boundary it is read as a function (XxYxZ -> value) so it is interpolated betwen each point you give (your ancient mesh) and read to your new mesh

moreover if you know the change you have done in your geometry you can adjust your profile quite easily in the BC setup: just replace X,Y,Z by the value you want
or create new variable to match the old profile with the new BC, exemple: X0 = X*cos(theta) + Y*sin(theta)

I suppose it works the same in the Turbo module
Thanks - I think specifying the surface I'm applying the new inlet BC to would be fairly easy as it's at a constant radius from the axis of rotation. However, what I have now is a spanwise profile of circumferentially-averaged total pressure. It seems that CFX does not have a method of using this, as it only wants a profile specifying the conditions across the entire inlet. Any idea if there's a way of using this profile?
cbrian is offline   Reply With Quote

Old   March 4, 2015, 23:13
Default
  #10
Senior Member
 
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33
Opaque will become famous soon enough
I think you are confusing mesh coordinates with turbo coordinates. Once you obtain the spanwise profile by circumferentially averaging the previous solution, what you really have is a f(x,y,z) that when plotted show circumferential bands, but still a function of x,y,z on the surface.

Just export the spanwise profile you got as a (x,y,z) function, and import it in CFX-Pre. Once you hook it up on your inlet, you can visualize what you got and I bet you will see the spanwise distribution you expect.
Opaque is offline   Reply With Quote

Reply

Tags
cfd, cfx, profile boundary cond.

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Fan simulation with inlet and outlet duct for finding fan curve chaudhry_hashim FLUENT 0 August 6, 2014 11:49
help with boundary profile in pressure inlet quiqui FLUENT 21 June 18, 2013 13:55
Strange velocity profile at the inlet for a flow inside a cylindrical pipe michmich OpenFOAM Running, Solving & CFD 0 July 2, 2012 04:37
total pressure boundary problem ==> flow from outlet to inlet!! mrshb4 OpenFOAM 0 November 20, 2010 13:41
steam flow in a pipe driven by a pressure gradient between inlet and outlet SalvoCalvo COMSOL 0 March 11, 2010 07:52


All times are GMT -4. The time now is 04:54.