# Impellar driven fluid flow in centrifugal pump

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 March 29, 2015, 02:58 Impellar driven fluid flow in centrifugal pump #1 Senior Member   sluzzer Join Date: Jul 2014 Posts: 129 Rep Power: 5 Is it possible to simulate centrifugal pump just like actual testing.. I mean both inlet and outlet are ambient pressure and when the impeller rotates flow and pressure develops. From tutorial I understood that we must specify the Pressure difference and/or mass flow rate and we can simulate for the Head. Assume we dont know the mass flow rate and pressure difference and we know only the rpm of the pump. In this case is it possible to simulate for flow and pressure rise, from the rotation of impeller alone? I have gone through the gear-pump/gerotor-pump cfx tutorial, in which the flow is simulated through rpm alone by using 'Immersed solid' method. Anybody has used this method for centrifugal pump?

 March 29, 2015, 05:09 #2 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 14,097 Rep Power: 109 Do not use immersed solids to model a centrifugal pump. Use rotating frames of reference. Look at the axial rotor stator tutorial models for how to do this. Yes, you can model a known rpm with ambient pressure on inlet and outlet reservoirs.

 March 29, 2015, 23:36 #3 Senior Member   sluzzer Join Date: Jul 2014 Posts: 129 Rep Power: 5 Thanks for the reply GHorrocks Can you please explain why we should not use the immersed solid method? Also can you please tell in brief that what is the difference between these three methods? i.e, between default analysis method by specifying mass flow rate, rotating frame of reference method and immersed solid method.. Also which method is more appropriate method for doing transient analysis? that is flow variation with respect to rpm?! Thanks

 March 30, 2015, 02:18 #4 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 14,097 Rep Power: 109 Because immersed solids is poor at resolving the boundary layer. Rotating domains will allow you to do a mesh conformal to the impeller wall faces, and with good quality inflation layers. Immersed solid meshes are neither conformal to the impeller wall faces nor allow you to use inflation layers. The mass flow rate is the boundary condition you specify and that is a different thing. If you do the tutorials provided with CFX you will have a clearer idea of what these things mean.

 April 1, 2015, 23:46 #5 Senior Member   sluzzer Join Date: Jul 2014 Posts: 129 Rep Power: 5 Thanks GHorrocks for your inputs I have gone through both the Cavitation of centrifugal pump tutorial and Flow through Axial turbine stage tutorial. These are the difference i found: 1. In centrifugal pump tutorial, only one domain has been used and the stationary wall is specified as 'counter rotating wall' 2. In Axial turbine tutorial, one stationary domain and one rotating domain is specified. Both the domains are connected by 'Frozen Rotor' Interface. In your first reply, you mentioned that we can simulate impeller driven fluid flow by specifying atmospheric pressure at both inlet and outlet. But even in the axial turbine tutorial mass flow rate at the outlet is explicitly defined. Please clarify. Thank you

 April 2, 2015, 05:31 #6 Senior Member   Thomas MADELEINE Join Date: Oct 2014 Posts: 126 Rep Power: 5 in Axial turbine you have a stator (blades that don't move) and a rotor... so you can't model the stator by "cheating" a rotating domain with counter rotating walls... in the centrifugal pump there is no stator, so you can avoid the tow domains and the interface between. your domain is rotating and you "immobilize" some walls by setting a counter rotating velocity. for you BC, I will prefer an inlet total pressure if I can. for example if you are working in the atmosphere, you can assume that long time ago the air tank will be at 1 atm (with no velocity, so it is total pressure). then if you know the exit (the atmosphere by example) you can put (1 atm for example) a static pressure outlet. I don't know if it will work with two static pressure BCs, if somebody can confirm that i will miss a term to work (like when you put two velocity BCs) ?

 October 6, 2015, 10:00 #7 Senior Member   sluzzer Join Date: Jul 2014 Posts: 129 Rep Power: 5 Bringing back the old thread.. By setting an expert parameter (unchecking 'artificial boundary wall'), we can analyze by setting static pressure at the both inlet and outlet and the flow will be driven by rotation alone.. But we may face convergence difficulties..

 Tags centrifugal pump, cfx, impellar, transient

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post lynx OpenFOAM Paraview & paraFoam 4 January 20, 2016 12:58 Maralady ANSYS 0 February 18, 2013 18:52 CD adapco Group Marketing Siemens 3 June 21, 2011 08:33 saii CFX 2 September 18, 2009 08:07 max91 CFX 1 July 29, 2008 20:28

All times are GMT -4. The time now is 08:36.

 Contact Us - CFD Online - Privacy Statement - Top