# How to get compressibel flow inCFX 5.5

 Register Blogs Members List Search Today's Posts Mark Forums Read

 January 23, 2003, 15:34 How to get compressibel flow inCFX 5.5 #1 Thomas Johansson Guest   Posts: n/a Iīm a student that trying to optimize a turbo-restrictor that we have to use in our Formula SAE car.I want to know how to specify in CFX5 that I want compressibel flow(canīt find any info in Tutorials and help menu)since the flow in the restrictor will be choked when the airspeed approaching Mach 1,so far I have used "Air ideal gas" but my massflow is to high to be accurate. Thanks in advance. Thomas SWEDEN

 January 23, 2003, 17:22 Re: How to get compressible flow in CFX 5.5 #2 Glenn Horrocks Guest   Posts: n/a Hi Thomas, To model choked flow, you also need to use "Total Energy" as your heat transfer model in the fluid domain. Also, there are tutorials which use compressible flow - tutorial 8, "Supersonic flow over a wing" and tutorial 12, "Flow in an Axial Rotor/Stator Arrangement". Regards, Glenn Horrocks

 January 24, 2003, 15:19 Re: How to get compressible flow in CFX 5.5 #3 Thomas Johansson Guest   Posts: n/a Iīve tried to use "total energy" as heat transfer and I have looked at the tutorials mentioned but I canīt get it to work-and specifying supersonic didnīt work for me either. Maybe iīm doing something else wrong(I specify domain to:100kPa-Air ideal gas, and set the Boundary conditions to: inlet-100kPa and outlet to 52,8kPa that in teori should get M1 and choked flow-all air goes thru a convergent-divergent pipe with a 20mm minium diam.) looking forward to get some more info. regards Thomas

 January 25, 2003, 03:49 Re: How to get compressible flow in CFX 5.5 #4 Mike Guest   Posts: n/a You say you specify domain to 100kPa. This is OK, but you should understand that this is the reference pressure. All other pressures are relative to this. If you mean for your inlet to be 100kPa absolute, then you should specify the inlet value as 0 kPa. If you mean for your inlet to be 100kPa relative (i.e. 200kPa absolute in your case) then you already have the correct values. Similarly, the outlet pressure is relative to the reference pressure. Hope this helps, Mike

 January 25, 2003, 05:06 Re: How to get compressible flow in CFX 5.5 #5 Thomas Johansson Guest   Posts: n/a That explain why my massflow was twice as high as expected, so now it should work with correct "Boundary conditions". Thank you for the help, Mike and Glenn regards Thomas

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post CD adapco Group Marketing CD-adapco 3 June 21, 2011 08:33 ib FLUENT 1 March 26, 2007 13:11 stanley FLUENT 1 February 2, 2007 07:44 pxyz Main CFD Forum 37 July 7, 2006 08:42 Junl Main CFD Forum 1 February 4, 2000 22:24

All times are GMT -4. The time now is 06:18.