[pdhyani96]

hello guys, I understand that a source point acts on a single mesh element and acts a 3D source. So, If i am modelling a jet of 2 (mm^2) and the area of mesh element at point source location is 0.5 (mm^2), does the jet come out of assumed area or the area of the mesh?

Because we are required to provide mass flow rate and an injection velocity. I assume the area is calculated from that reference. In most cases the area of injection is going to be more than the area of that mesh element. Then how does the software model such an area if injection come out of a single mesh element only?

[ghorrocks]

Source points act on a single element only, even if the size of the implied source is bigger than a single element.

It has been a while since I looked at source points, but I am surprised you can specify both mass flow and velocity. This appears to me to over-constrain the definition. Are you sure that is correct? I cannot check as I am not at work at the moment.

[pdhyani96]

Yes, it does ask for velocity and mass flow rate. I had the same doubt. But my professor told me that a source point needs velocity and mass flow rate based on an area that a user assumes. But that idea didn’t help me in simulations

I am supposed to inject uniform flow spanwise on an airfoil. For that I have made sure that source points occupy every mesh element along the span. But my simulations show four equidistant bumps at the location on jets instead of a uniform flow across the span.

Also, if I change the number of elements spanwise, the pattern changes. But I am not able to see a uniform injection.

[Opaque]

May I ask what are you trying to simulate?

Are you modeling injection points on the surface of the airfoil?, i.e. film cooling

[Goenitz]

So to calculate a source/flux if you have reaction rate like mol m^-2 s^-1.. Then if we multiply this to the area (wall) at which the reaction is taking place so it will become mol s^-1. So it is correct or depends upon the number of elements or element area(which should be equal to wall area)? My case is mesh independent.

[ghorrocks]

It all depends on whether your reaction is a point, surface or volume reaction.

[Opaque]

Just for clarification,

For incoming flow, the velocity vector must be specified either directly or indirectly in several ways:

1 - Velocity Vector in any coordinate system
2 - Mass flow and flow direction
3 - Pressure of some kind and flow direction

The use of mass flow and velocity vector can be used, but (big one) the product of density * Velocity * Normal Area must be identical to the specified mass flow. Therefore, the velocity vector is implying the direction. Otherwise, there is an inconsistency between the two quantities.

[pdhyani96]

Yes, I am trying to have injection points for film cooling on a blade surface.

[pdhyani96]

Originally Posted by ghorrocks

It all depends on whether your reaction is a point, surface or volume reaction.

It is point source. I don't think there is any surface or volume reaction involved

[pdhyani96]

Originally Posted by Opaque

Just for clarification,

For incoming flow, the velocity vector must be specified either directly or indirectly in several ways:

1 - Velocity Vector in any coordinate system
2 - Mass flow and flow direction
3 - Pressure of some kind and flow direction

The use of mass flow and velocity vector can be used, but (big one) the product of density * Velocity * Normal Area must be identical to the specified mass flow. Therefore, the velocity vector is implying the direction. Otherwise, there is an inconsistency between the two quantities.

I agree with the logic. But the software does not allow me to select the normal area. I am assuming that based on given mass flow rate and velocity of injection, the software assumes an area. Correct?

But if that is true, it goes against the manual which states that the injection comes of that specified mesh element.

[ghorrocks]

You have misunderstood the post. The normal area in Opaque's equation is not something you set, it is implicit in the element you define to have the source point. This means it is driven by the element's cross section area. It is not something the user sets directly.

[pdhyani96]

Originally Posted by ghorrocks

You have misunderstood the post. The normal area in Opaque's equation is not something you set, it is implicit in the element you define to have the source point. This means it is driven by the element's cross section area. It is not something the user sets directly.

Okay, this clears most of the confusion. Mass flow is for defining strength, velocity is for defining direction. But all in all, the net mass flow rate should equal rho*area*velocity. Thank you guys! I really appreciate it.