CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > CFX

CFX Compressor

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree3Likes
  • 1 Post By Opaque
  • 1 Post By ghorrocks
  • 1 Post By ghorrocks

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   May 7, 2020, 11:43
Default CFX Compressor
  #1
Member
 
Join Date: Mar 2020
Posts: 33
Rep Power: 3
UsamaQ is on a distinguished road
Dear all, I simulated a centrifugal compressor and is currently using CFD post to view contours.

I have a fluid domain which is only rotating in impeller section while diffuser and inlet are stationary. When I visualize the vector plot of velocity in CFD post, the vectors are rotating in all domains which is weird to me. For boundary conditions, the blades surfaces, hub and shroud are no slip walls (should I use counter rotating wall option for shroud?)

Second thing is Absolute pressure, when I plot the contour of absolute pressure I see very large negative values of pressure, which is wrong I guess. When I clip it by range from 0 to negative_max value, I see whole domain showing negative value. Why is that? I have attached pictures.

Thank you.

Last edited by UsamaQ; May 17, 2020 at 18:10.
UsamaQ is offline   Reply With Quote

Old   May 7, 2020, 13:45
Default
  #2
Senior Member
 
Join Date: Jun 2009
Posts: 1,398
Rep Power: 26
Opaque will become famous soon enough
The last figure does not help to visualize the problem for Absolute Pressure

Have you tried clipping from below, i.e. Min = 0 [Pa]. You want to see the blue regions. That is where the negative values are.
UsamaQ likes this.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum.
Opaque is offline   Reply With Quote

Old   May 7, 2020, 17:27
Default
  #3
Member
 
Join Date: Mar 2020
Posts: 33
Rep Power: 3
UsamaQ is on a distinguished road
I clipped it below [0 Pa] to lowest value in negative i.e (-3.113e+06 Pa) as shown on the left side.
UsamaQ is offline   Reply With Quote

Old   May 7, 2020, 18:50
Default
  #4
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 16,720
Rep Power: 130
ghorrocks is a jewel in the roughghorrocks is a jewel in the roughghorrocks is a jewel in the roughghorrocks is a jewel in the rough
This FAQ may help with the frame of reference: https://www.cfd-online.com/Wiki/Ansy...f_reference.3F

The negative absolute pressure is typical in incompressible simulations as the pressure is unbounded. In reality these regions would cavitate or have some other effect to reduce the size of the negative absolute pressure region. As Opaque says, you should not ignore these regions by clipping the results as it is telling you something - these regions are likely to cavitate.
UsamaQ likes this.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum.
ghorrocks is offline   Reply With Quote

Old   May 7, 2020, 19:01
Default
  #5
Member
 
Join Date: Mar 2020
Posts: 33
Rep Power: 3
UsamaQ is on a distinguished road
Hi Glenn. I checked the FAQ and I set shroud wall to counter rotating w.r.t to relative frame. Now, the velocity on shroud wall is zero w.r.t stationary frame.

Now the problem is that If you see the absolute pressure regions, the dark blue region are not present where the negative values lie. I used probe at different points in the light blue region in the contours and values there are positive. When I clip it below 0 Pa to lowest values, you see the whole domain becomes red which is confusing. Shouldn't the clipping only show the regions below 0 Pa. This is confusing and I couldn't locate the dark blue regions or negative pressure regions.
UsamaQ is offline   Reply With Quote

Old   May 7, 2020, 19:10
Default
  #6
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 16,720
Rep Power: 130
ghorrocks is a jewel in the roughghorrocks is a jewel in the roughghorrocks is a jewel in the roughghorrocks is a jewel in the rough
Do an isosurface of absolute pressure, set to zero pressure. That will show you the negative region more clearly. It is likely to be only a very small region so you will probably have to zoom in lots to find it.
UsamaQ likes this.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum.
ghorrocks is offline   Reply With Quote

Old   May 7, 2020, 19:24
Default
  #7
Senior Member
 
Join Date: Jun 2009
Posts: 1,398
Rep Power: 26
Opaque will become famous soon enough
For curiosity,

where did I miss the fluid is incompressible? and

when did we start calling a machine handling an incompressible fluid a compressor?
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum.
Opaque is offline   Reply With Quote

Reply

Tags
cfd, cfd post, cfx, contour plot, turbomachinery

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
CFX vs. FLUENT turbo CFX 4 April 13, 2021 08:08
Centrifugal Compressor Efficiency albertotato CFX 3 May 2, 2020 02:54
How does the CFX distinguish between Turbine and Compressor? shivasluzz CFX 6 August 6, 2016 08:30
CFX pressure in Simulations problem nasdak CFX 1 April 14, 2010 13:22
CFX 4.4 installation problem Pandu Sattvika CFX 1 December 1, 2001 04:07


All times are GMT -4. The time now is 03:14.