# calc in table viewer

 Register Blogs Members List Search Today's Posts Mark Forums Read

 July 20, 2007, 07:44 calc in table viewer #1 jan Guest   Posts: n/a let say i want to define density *0.5 how do i do this ,becuase i can do it with a variable but when i want to have this in table viewer it cannot done why is that , so i cannot include this in a report

 July 21, 2007, 11:48 Re: calc in table viewer #2 Jinji Guest   Posts: n/a Very nice question, I'd like to know it as well!!

 July 22, 2007, 18:30 Re: calc in table viewer #3 Glenn Horrocks Guest   Posts: n/a Hi, What do you mean? Do you want to define density as a function of other variables so you can do a compressible or buoyant flow simulation? Glenn Horrocks

 July 23, 2007, 06:42 Re: calc in table viewer #4 jan Guest   Posts: n/a yes define as a function of other variables like determine of surface drag you need 0.5 times density or density /2 its just impossible to do this in table viewer

 July 23, 2007, 09:19 Re: calc in table viewer #5 Robin Guest   Posts: n/a The table viewer can only display single values. The expression 'density*0.5' resolves to a variable. If you write an expression as a function of density which resolves to a single value you will have no problem. For example, enter the following expression into a table cell =massFlowAve(1/2*density)@wing. Regards, Robin

 July 23, 2007, 11:24 Re: calc in table viewer #6 jan Guest   Posts: n/a thanks only if you do more then this i still have a problem entering the drag formula in that table cell or do you also a have a solution for this?

 July 23, 2007, 11:50 Re: calc in table viewer #7 Robin Guest   Posts: n/a Make sure your Expression results in a single value. If your drag formula does, you will not have a problem. Post the actual expression you are using here if you like and I can point out any problems. -Robin

 July 23, 2007, 12:05 Re: calc in table viewer #8 jan Guest   Posts: n/a Cd = force_x()@Surface / (0.5*Rho*U^2*A)

 July 23, 2007, 13:00 Re: calc in table viewer #9 Robin Guest   Posts: n/a Ah. The problem is that while the numerator of your expression results in a single value, the denominator doesn't. Instead, use: Cd = force_x()@Surface/areaAve(0.5*Rho*U^2*A)@Surface Regards, Robin

 July 23, 2007, 13:30 Re: calc in table viewer #10 Robin Guest   Posts: n/a Actually, the numerator should be calculated as a mass flow average on your reference boundary, probably your inlet, since the dynamic pressure at the surface will be zero. Also, since the dynamic pressure is simply the difference between the static and total pressure, 'p-ptot' is an easier expression to use. This will also give you the right dynamic pressure for compressible flows. Cd = force_x()@Surface/massFlowAve(p-ptot)@Inlet Regards, Robin

 July 23, 2007, 13:31 oops #11 Robin Guest   Posts: n/a Sorry, meant denominator, not numerator. I think you get the point

 July 23, 2007, 15:55 Re: oops #12 jan Guest   Posts: n/a thanks i will try that tomorrow now 22.00 thanks a bunch anyway

 July 23, 2007, 16:02 Re: calc in table viewer #13 jan Guest   Posts: n/a also can you tell me how i can get in legend CP values that is a presssure coeff P-Pa but i guess that massflow Ave (p-ptot)@default default domain is that right?

 July 23, 2007, 16:08 Re: calc in table viewer #14 Robin Guest   Posts: n/a I'm not sure I understand. Do you want to plot the pressure coefficient? If that is the case, just define a Variable in Post equal to 'ptot-p' or 'Total Pressure - Pressure' and plot it. (I meant to use 'ptot-p' earlier but it came out as 'p-ptot'. Damn Mondays ;-) Regards, Robin

 July 23, 2007, 16:58 Re: calc in table viewer #15 jan Guest   Posts: n/a areaAve(0.5*Rho*U^2*A)@Surface still cannot define this ok can do 0.5*rho but not the part U^2 this is the speed in ^2 so i cannot define this drag coeff

 July 24, 2007, 10:04 Re: calc in table viewer #16 Robin Guest   Posts: n/a The speed squared would be u^2+v^2+w^2, 'U' is not a variable. Try: areaAve(0.5*Density*(u^2+v^2+w^2))@Surface Or you could define U in another expression as: U = sqrt(u^2+v^2+w^2) ... and us it in your original. What is the '*A' for? Also, keep in mind that for the drag coefficient you don't want the dynamic pressure at the surface, you need it from a reference location such as your inlet or a plane upstream. Also, as I pointed out before, the easiest way to calculate the dynamic pressure is to subtract the static pressure from the total pressure (Total Pressure is sometimes referred to as the Stagnation Pressure). Regards, Robin

 July 24, 2007, 13:07 Re: calc in table viewer #17 jan Guest   Posts: n/a thanks why w^2 ? and A is aera and i cannot do a CP on the object CP= coeff pressure this is used to see how each pascal is this means or it has pressure force yes or no and normaly it between -1 and 2 with this you can see where there is a problem spikes are easily seen and its effect also where from laminar goes to turbulant its impossible for me to see on the object p-ptot who to solev this?

 July 24, 2007, 18:38 Re: calc in table viewer #18 jan Guest   Posts: n/a The speed squared would be u^2+v^2+w^2, 'U' is not a variable. Try: areaAve(0.5*Density*(u^2+v^2+w^2))@Surface Or you could define U in another expression as: U = sqrt(u^2+v^2+w^2) sorry does not work!!!!!!!!!

 July 25, 2007, 09:43 Re: calc in table viewer #19 Robin Guest   Posts: n/a Did you include an equal sign '=' ahead of the expression when you entered it into the table cell? Does the expression work in the expression editor?

 July 25, 2007, 11:56 Re: calc in table viewer #20 jan Guest   Posts: n/a yes i did have the = sign and it does work in experssion but not in table viewer

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post jaswi OpenFOAM Programming & Development 3 October 29, 2015 14:42 Daniel CFX 1 May 11, 2006 12:19 furkan Siemens 0 April 4, 2006 10:23 Andrew Fine CFX 2 December 16, 2005 00:39 Christian Main CFD Forum 2 April 10, 2003 04:06

All times are GMT -4. The time now is 17:32.