|
[Sponsors] |
September 24, 2011, 14:05 |
Query on POROUS MEDIA
|
#1 |
New Member
MPrabanchan
Join Date: Sep 2011
Location: Tamilnadu, India
Posts: 8
Rep Power: 14 |
I'm doing a project in Pressure Drop analysis on a Catalytic Converter.In my model I need to split the porous media in to 3 regions to have different porosity in each region.Can any one say how to split?
|
|
September 25, 2011, 07:16 |
|
#2 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,665
Rep Power: 143 |
If the media is a volume then define 3 mesh volumes. If the media is thin then define 3 cross sections, you can call them interfaces if you like.
|
|
September 25, 2011, 12:07 |
|
#3 |
New Member
MPrabanchan
Join Date: Sep 2011
Location: Tamilnadu, India
Posts: 8
Rep Power: 14 |
I Split the regions while modeling.There comes a error report as below
"Default Domain Substrate3 Substrate1 Substrate2 If the isolated regions do not have the pressure level set either by the boundary conditions or using a reference pressure equation, you may encounter severe robustness problems. This situation may have arisen because a domain interface was not properly defined during problem setup. Please carefully check the setup. The solver will stop now and write a results file. The isolated regions can be visualised in CFX Post by making plots of the variable "Isolated Volumes". If you are sure that the pressure level is set in each isolated fluid region then you can force the solver to turn off this check by setting the expert parameter "check isolated regions = f". +--------------------------------------------------------------------+ | An error has occurred in cfx5solve: | | | | The ANSYS CFX solver exited with return code 1. | +--------------------------------------------------------------------+ End of solution stage." |
|
September 25, 2011, 19:12 |
|
#4 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,665
Rep Power: 143 |
Yo have not set it up correctly. The domain should include all these regions. Then you define the volumes as sub-domains.
|
|
September 25, 2011, 19:47 |
|
#5 |
Senior Member
Join Date: Oct 2010
Location: Zurich
Posts: 176
Rep Power: 15 |
As Glen already said above, you have not setup your case properly.
i recently did something very similar. I had a layer of porous medium and I wanted to define different porosity and permeability in three different parts the porous volume. this is how I did it. 1. I use structured mesh. So I simply assigned different blocks to the three regions thus defining separate volumes for the three regions of the porous medium. 2. then in CFx, I created three separate domains each containing one region of the porous medium. For each domain, I defined porous medium parameters as per my need. 3. I created porous-porous interfaces between the three porous domains. And it worked without any problem. hope this helps. |
|
September 25, 2011, 20:31 |
|
#6 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,665
Rep Power: 143 |
You do not need to make the porous regions different domains. They can all be one domain, just the porous region defined as a sub-domain.
The only reason why you would put them as different domains is to generate interfaces so you can put interface conditions (eg resistance) on them. |
|
September 26, 2011, 19:38 |
|
#7 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,166
Rep Power: 23 |
Instead of remodeling you could also define the porosity with a user defined function with respect to a global coordinate. I'd do this instead of re-modeling/remeshing and redefining a bunch of boundary conditions.
|
|
Thread Tools | Search this Thread |
Display Modes | |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Multiphase Porous Media Flow - Convergence Issues | VT_Bromley | FLUENT | 7 | May 14, 2020 17:34 |
Porous media setup issues in Fluent | Bernard Van | FLUENT | 29 | January 26, 2017 05:09 |
How to model granular flow through porous media | Axius | FLUENT | 2 | August 7, 2014 11:34 |
species mass source in porous media ? | PK | FLUENT | 0 | February 16, 2007 12:12 |
porous media: Fluent or Star-CD? | Igor | Main CFD Forum | 0 | December 5, 2002 16:16 |