[magicbretzel]

Hi all,

I am running simulations of IC engines (moving boundaries) and shortly after I start the simulation I get this warning many times:

A cell pair was created with 16 cells at 0.00789812 0.00815266 0.00135936. This cell may reduce accuracy and/or stability. Consider refining the grid in this region. This warning will only be printed 50 times per process

What does it mean and how can I fix my mesh? I tried to refine the mesh as suggested but I keep getting the warning, so I am thinking that it might have something to do with my boundaries...

Cheers,
Guillaume

[jetcheve]

Originally Posted by magicbretzel

Hi all,

I am running simulations of IC engines (moving boundaries) and shortly after I start the simulation I get this warning many times:

A cell pair was created with 16 cells at 0.00789812 0.00815266 0.00135936. This cell may reduce accuracy and/or stability. Consider refining the grid in this region. This warning will only be printed 50 times per process

What does it mean and how can I fix my mesh? I tried to refine the mesh as suggested but I keep getting the warning, so I am thinking that it might have something to do with my boundaries...

Cheers,
Guillaume

Hi, Guillaume!

When CONVERGE creates a mesh it looks at the volume of a cell cut by a surface compared to a normal neighboring cell. If the cut cell is less than 30% of the volume of the neighbor, the two are combined. If more cells are needed it combines more neighbors. If too many are needed the quality of the mesh can suffer - this is the warning you are seeing.

Often, in a ICE simulation this can occur in the valve gap. Does the coordinate provided match with the valves? Also, how big is the gap in your simulation and how big are the cells in it?

Thanks!

- John

[magicbretzel]

Hi John,

Thanks for your answer! Here is a slice showing the mesh around the valves.

https://drive.google.com/file/d/1gmG...ew?usp=sharing

The cell size is 1mm around the valves, and the valve gap is 0.2 mm initially (closed position). When fully valve is fully open, the gap is about 6mm. I don't understand what you mean when you ask if the coordinate provided match with the valves. I believe that I need to refine the mesh locally around the valve gap?

[jetcheve]

Originally Posted by magicbretzel

Hi John,

Thanks for your answer! Here is a slice showing the mesh around the valves.

https://drive.google.com/file/d/1gmG...ew?usp=sharing

The cell size is 1mm around the valves, and the valve gap is 0.2 mm initially (closed position). When fully valve is fully open, the gap is about 6mm. I don't understand what you mean when you ask if the coordinate provided match with the valves. I believe that I need to refine the mesh locally around the valve gap?

Guillaume - It looks like your embedding isn't fine enough in the area of the valve. I would increase embed scale on the valve angle and seat embedding by 2. Studio should also warn you if your embedding is too coarse resulting in possible pairing.

As for the point about checking if the coordinate provided is in the area of the valve - you can copy that coordinate and make a vertex at that point to see where it is. If it is in or close to the valve gap that would tell you if the valve is a possible culprit in your problem.

Thanks!

- John

[magicbretzel]

John,

Indeed the coordinate of the problematic cell is very close to the valve angle. Adding embedding at the valve angle and seat solved the issue, I am not getting the cell pairing warning message anymore.

Thank you for your help!

Guillaume

[jetcheve]

Originally Posted by magicbretzel

John,

Indeed the coordinate of the problematic cell is very close to the valve angle. Adding embedding at the valve angle and seat solved the issue, I am not getting the cell pairing warning message anymore.

Thank you for your help!

Guillaume

Great! Glad we could work that out for you.

- John