CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > FloEFD, FloWorks & FloTHERM

SolidWorks Flow Sim - Discrepancy in heat transfer coefficient

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   May 9, 2023, 11:53
Arrow SolidWorks Flow Sim - Discrepancy in heat transfer coefficient
  #1
New Member
 
Join Date: May 2020
Posts: 21
Rep Power: 5
SSG_NJ is on a distinguished road
Hi everyone!

How are you all doing?

I am working on a thermal model in SW Flow Simulation. I noticed a discrepancy in the value of the convective heat transfer coefficient ('h') obtained directly from the simulation (i.e. by using a surface goal) vs. calculating it via an equation goal using Newton's law of cooling, and I am unable to get to the bottom of this.

To verify which of these values are correct, I calculated the heat generated in the model (with an equation goal) using the 'h' obtained directly from the simulation (i.e. by using a surface goal) and compared it to the known value of heat generation which was inputted in to the model, and the two values differ greatly.

The flow is turbulent, forced, and the heat convects from a heat generation source directly onto the fluid.

Kindly help.

Thanks !
SSG_NJ is offline   Reply With Quote

Old   June 6, 2023, 11:20
Default
  #2
New Member
 
Florian
Join Date: Feb 2015
Posts: 13
Rep Power: 10
native is on a distinguished road
Hi SSG_NJ

I have two questions regarding your problem:
  1. Did you take radiation into account in your model?
  2. The heat transfer coefficient isn't equal on the whole geometry. Did you compare Min and Max value to you calculated value somehow? Is it at least in the range between Min and Max?

Best regards
Florian
native is offline   Reply With Quote

Old   June 20, 2023, 13:16
Default
  #3
New Member
 
Join Date: May 2020
Posts: 21
Rep Power: 5
SSG_NJ is on a distinguished road
Hi Florian,

How are you? Apologies for the late response.

To answer your questions,
1. There is no radiative heat transfer in the model
2. The calculated heat transfer coefficient (using an equation goal) is 3 orders of magnitude higher than the heat transfer coefficient obtained directly from the simulation. In the equation goal, I calculated 'h' as : h = SG Average heat flux /(SG Average temperature of solid - SG Average temperature of fluid), {where SG denotes Surface Goal}

Please advise!
SSG_NJ is offline   Reply With Quote

Old   June 22, 2023, 11:02
Default
  #4
New Member
 
Florian
Join Date: Feb 2015
Posts: 13
Rep Power: 10
native is on a distinguished road
Alright, so I think the deviation results from your definition of the fluid temperature as a surface goal. For these kind of proportionality constants or dimensionless numbers, usually the free stream temperature is used. The fluid temperature close to the wall is (almost) the same as the temperature of the wall itself. Thus, this results in a way higher heat transfer coefficient compared to the value calculated by using the free stream temperature.

I modeled the problem myself, using FloEFD for Creo. The copper sphere has a diameter of 0.1 m and is heated by 5 W. The free stream air velocity is 1 m/s and freestream temperature is 20 C. As shown in the attached figure, the heat transfer coefficients from a surface goal and from an equation goal are the same. By the way, they also compare well to a literature value of 15.9 W/(m^2 K) for this case. The second equation goal is calculated with the fluid temperature on the surface of the sphere. This one doesn't fit at all.

Hope this helps.
Best
Florian
Attached Images
File Type: png Sphere_Heat_Transfer_2.png (190.4 KB, 12 views)
native is offline   Reply With Quote

Reply

Tags
discrepancy, flow simulation, heat transfer coefficient, solidworks

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Radiation in semi-transparent media with surface-to-surface model? mpeppels CFX 11 August 22, 2019 07:30
Heat transfer coefficient near the wall in two phase flow XavierW Main CFD Forum 0 February 18, 2016 10:37
Question about heat transfer coefficient setting for CFX Anna Tian CFX 1 June 16, 2013 06:28
Error finding variable "THERMX" sunilpatil CFX 8 April 26, 2013 07:00
Heat Transfer Coefficient in Compressible Flow 3D turbine cascade Karkoura CFX 0 March 10, 2011 15:35


All times are GMT -4. The time now is 13:52.