
[Sponsors] 
March 15, 2014, 09:10 
Re: Boundary conditions for current carrying conductor

#1 
Member
Yash Ganatra
Join Date: Mar 2013
Posts: 67
Rep Power: 6 
Hi,
I am working to find magnetic field around a cylindrical current carrying conductor. I have used Magnetic vector potential and electric scalar potential (APhi) and written UDS to solve in FLUENT. However, my results are not tallying with the analytical (rather intuitive) results that magnetic field is directly proportional inside conductor and inversely outside. I wonder if this is because of the boundary conditions I have given. I have attached the image of BC and the UDF I have written. 1. Could anyone kindly clarify that in the inbuilt MHD module, mathematically what do the conducting and insulating boundary conditions mean? 2. I have given Zero specified flux at the conductor end for A? I had read that the direction of A is the same as that of current density, so is that BC correct? Thank you, Regards, Yash Ganatra 

March 17, 2014, 05:24 

#2 
Senior Member
Join Date: Oct 2013
Posts: 374
Rep Power: 7 
I can't really tell you anything about FLUENTrelated issues, but for me the boundary condition for the magnetic vector potential that worked was the one implemented in this OpenFOAM solver ("Open boundary conditions (infinite space)"):
http://www.cfdonline.com/Forums/ope...tml#post471052 Using this boundary condition I get the expected linear dependence of the magnetic field in the conductor and the decreasing field outside of it. The idea behind this is that the electromagnetic field also depends on the geometry outside of the simulated area (i.e. different permeabilities attracting or repel field lines). This leads to a distortion near the boundaries, if not accounted for properly. Unfortately the thesis related to this solver is in Latvian, however it quotes a document from another magnetic field calculation tool where the used formula for the boundary is specified. I hope this helps you somewhat, unfortunately I can't assist with the implementation of said boundary condition in FLUENT. 

March 20, 2014, 04:04 
Re: Queries regarding UDS for electromagnetic problem

#3 
Member
Yash Ganatra
Join Date: Mar 2013
Posts: 67
Rep Power: 6 
I have used Magnetic vector potential and electric scalar potential (Aphi)
The equations are: 1. div (sigma grad(phi)) =0 2. laplacian (A) = mu0*j j: currenr density ,sigma: electrical conductivity Problem: I am not getting the expected linear variation of magnetic field inside the conductor and inverse variation outside the conductor. 1. I have referred thesis where the same problem has been implemented in OpenFoam. The boundary conditions have been mentioned as grad (A) / grad (phi) =0 which translates to specified flux boundary condition in FLUENT, right? In all these thesis, I cannot understand why no boundary conditions have been given at the interface? 2. However, in FLUENT, I need to give boundary conditions to the individual components (i.e Az and Ar) and I am not able to understand which boundary conditions to give. 3. Also at the interface I am getting two walls  one named which has adjacent cell zone as conductor and the other has an adjacent cell zone as domain. References: 1. Plasma ArcWelding Simulation with OpenFOAM, MARGARITA SASSTISOVSKAYA 2. Implementation in the ANSYS finite element code of the electric vector potential TΩ,Ω formulation and its validation with the magnetic vector potential AV,A formulation, Pietro Testoni I have attached the code, the boundary conditions in the OpenFoam thesis, and my plot of magnetic field. 1. I suspect that I have given boundary conditions wrongly. 2. I have tried increasing conductivity of air but got no difference in result. Could anyone please give their opinions? Thank you, Regards, Yash Ganatra { Magfield : contour plot of magnetic field BC_Thesis: BC taken in [1] Domain_Thesis : Domain in [1]  similar to the domain modeled in FLUENT Boundary Conditions_GUI : snapshot showing 2 conductor walls CopperBar : UDS written Conductivity air: 1e5 S/m Conductivity copper: 2700 S/m } 

March 20, 2014, 07:21 

#4 
New Member
Juris Vencels
Join Date: Sep 2012
Location: Sweden, Stockholm
Posts: 11
Rep Power: 6 
First of all check whether relative magnetic permeability of the cylinder is 1. Although from your code seems that you are using model similar to Huang, then by default this should be fine.
Difference between my work and work of Huang.
In Testoni and my work used boundary condition abbreviations:


March 20, 2014, 08:13 

#5 
Member
Yash Ganatra
Join Date: Mar 2013
Posts: 67
Rep Power: 6 
Hi,
Thank you very much for your reply. 1. I have solved in a way similar to Huang. I have solved those equations in all the regions. 2. I have used A=0 on the far_wall side. 3. I am not clear how to implement the zero normal gradient BC in terms of the components of A (i.e A_r and A_z). FLUENT by its GUI allows to specify either a value or a flux and since I have 2 eqns for A, I need to specify BC for A_r and A_z 4. Could you kindly clarify what you imply by "Your problem definitely is not in these boundary conditions". I have S12 which is defined as a wall according to FLUENT and I need to specify BC there. I have attached my geometry. Thank you Regards, Yash Ganatra 

March 20, 2014, 08:39 

#6 
New Member
Juris Vencels
Join Date: Sep 2012
Location: Sweden, Stockholm
Posts: 11
Rep Power: 6 
How in your program B=curl(A) is calculated?


March 20, 2014, 09:35 

#7 
Member
Yash Ganatra
Join Date: Mar 2013
Posts: 67
Rep Power: 6 
B (azimuthal) = d(Ar)/dAz  d(Az)/dAr
in axisymmetric coordinates according to FLUENT documentation, 0> axial direction(along X axis) 1> radial direction. I have written user defined scalar transport eqn: 2 for A (Ar and Az) and one for electric scalar potential phi so, Bz = C_UDSI_G(c,t,1)[0]  C_UDSI_G(c,t,0)[1] Here 0: index for eqn solving Az 1: index for Ar G: gradient (c,t denote cell (control volume) and t denotes the thread (collection of cells)) Thank you, Regards, Yash Ganatra 

March 24, 2014, 10:32 

#8 
Member
Yash Ganatra
Join Date: Mar 2013
Posts: 67
Rep Power: 6 
Hi,
I could solve the problem. The problem was specifying conductor walls. Do not specify wall BC. Instead manipulate Diffusivity UDS to account for different conductivities. Ex: if r> ro then return... if r< r0 return Thank you Regards, Yash Ganatra 

Tags 
conductor, electric potential, magnetic field, mhd problem 
Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Question about heat transfer coefficient setting for CFX  Anna Tian  CFX  1  June 16, 2013 06:28 
symmetry boundary conditions in cfx  lost.identity  CFX  41  May 22, 2013 07:21 
inlet boundary conditions  newOFuser  OpenFOAM  1  January 10, 2013 09:08 
Trimmed cell and embedded refinement mesh conversion issues  michele  OpenFOAM Other Meshers: ICEM, Star, Ansys, Pointwise, GridPro, Ansa, ...  2  July 15, 2005 04:15 
Please help with flow around car modelling!  Tudor Miron  CFX  17  March 19, 2004 20:23 