CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > FLUENT

mesh interfaces

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   September 20, 2014, 01:27
Post mesh interfaces
  #1
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Hi!
Can someone explain to me all of the difference between "mixing plane" and "mesh interfaces"?
Which solution is more accurate?

I'd be very grateful if someone help me!
amin.z is offline   Reply With Quote

Old   September 20, 2014, 06:00
Default
  #2
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
Hi Amin,
if I understand correctly the mixing plane is a model.
Mixing plane is also an interface, suitable for certain problems, where you can create a plane between 2 zones, a rotor and a stator.
Fluent guide describes this model to be able to average the results on the mixing plane in the circumferential or axial direction, by averaging these values (area-weight or mass or mixed-out) and by creating profiles of flow properties.
These results are passed from the downstream zone to the upstream zone, on the mixing plane.

On the other hand, an interface is a generic couple of surfaces, on which there is no specific calculation as inthe mixing plane, I think variables are only passed across these surfaces; usually they are used to connect 2 zones with different meshes or to simulate moving mesh problems.

I don't have experience with the mixing plane model, but it seems that the unsteady state moving mesh is the most accurate model.

Daniele

Last edited by ghost82; September 20, 2014 at 11:41.
ghost82 is offline   Reply With Quote

Old   September 20, 2014, 11:34
Default
  #3
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Dear Daniele! Thanks for your reply!
You did mention the useful tips! But there are still some problems:

When should we use mixing plane model or mesh interfaces?
in the same problems which are more accurate?
and with sliding mesh which is more suitable?

My project is about the rotating air inside a rotating electric motor.
There is an interface face between two domains and I'm using periodic BC for two domains with 60 and 24 degrees! Angular velocity is 2000 rpm!
Which model do you recommend?

Thank you in advance for your help
amin.z is offline   Reply With Quote

Old   September 20, 2014, 11:39
Default
  #4
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
Please post a sketch of the 2 domain zones and where interfaces are.

Daniele
ghost82 is offline   Reply With Quote

Old   September 20, 2014, 12:01
Default
  #5
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
2 photos attached
Forgive me if the photos are not clear enough!
Attached Images
File Type: jpg 3.JPG (56.9 KB, 31 views)
File Type: jpg 4.JPG (63.2 KB, 25 views)
amin.z is offline   Reply With Quote

Old   September 20, 2014, 12:04
Default
  #6
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
The rotary part is formed from a rotating fan with 15 blades and spinning rotor!
I'm modeled the fan with 1 blade(1:15 with 24 degrees) and rotor with 60 degrees!
amin.z is offline   Reply With Quote

Old   September 20, 2014, 13:20
Default
  #7
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
Ok Amin, it's clear your problem.
Consider that what you call interface 1 and interface 2 are not interfaces, but 2 (partially) overlapped surfaces: you will build one interface with that 2 surfaces in fluent, what you call interfaces 1 and 2.
Mixing plane is suitable for your problem, because you can create the plane between the 2 zones.

However, I have not experience with this model, I only used mrf/sliding mesh (without mixing plane) so I don't know if the model will be accurate enough.

I think you can try simple mrf, mrf+mixing plane (steady solver, they should not take too much time to get solved), and if you are not satisfied with your results switch to sliding mesh (unsteady).

Daniele
ghost82 is offline   Reply With Quote

Old   September 20, 2014, 15:45
Default
  #8
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Dear friend!
But I think this two faces are interface! I think that could choose the faces as interfaces because I'm using periodic BC!
And I used mrf with interfaces mesh and it's almost converged! But I'm looking for a method with less numerical errors!
amin.z is offline   Reply With Quote

Old   September 20, 2014, 16:11
Default
  #9
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
No Amin, I think that the vertical lateral faces are periodic bc, not interfaces.
You should set these faces as periodic.
As I written try to switch to the mixing plane model+mrf, then to sliding meshes, so to see if there are macro errors in calculaion.
I'm not at home now, tomorrow I will sketch what I want to say.

Daniele
__________________
Google is your friend and the same for the search button!

Last edited by ghost82; September 21, 2014 at 05:36.
ghost82 is offline   Reply With Quote

Old   September 21, 2014, 00:50
Default
  #10
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Oh! Amazing point!
I'm waiting for your sketch!

Tnx for your help dear!
amin.z is offline   Reply With Quote

Old   September 21, 2014, 05:26
Default
  #11
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
In my opinion, here is my setup, assuming 2 rotor zones and a stator (if I don't understand correctly your problem please clarify better).
All faces "parallel" to the flow should be set as periodic rotational (not interfaces!).
All couples of faces connecting stator-rotor zones (normal to x axis in my sketch) should be set as interfaces periodic repeats.

N.B.: if you use sliding mesh, your mesh is moving, so interfaces (periodic repeats) are a must: this ensures that when surfaces of the interfaces don't overlap, they are treated as periodic repeats.

If you use mrf or mrf+mixing plane, "interface" is a must, but you can avoid creating the "interface 2", because in this interface the 2 surfaces completely overlap and your mesh doesn't move during calculation.

If you plan to switch to sliding mesh consider to create all interfaces, also for mrf calculations, so to not have to modify your geometry when you switch to sliding mesh.

Daniele
Attached Images
File Type: jpg cfd.jpg (55.4 KB, 23 views)
ghost82 is offline   Reply With Quote

Old   September 22, 2014, 03:07
Default
  #12
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Dear daniele!
Tnx! Your suggestion is same my model!
I used mrf and the problem is converged!

But I have an important question:
If we assume that angle of right side rotor is 24 degrees ( 1/15 slice) and angle of left side rotor and stator is 60 degrees (1/6 slice), is the value of mass flow valid?
Is this value for 1/15 slice or 1/6 slice?

In my case the mass flow is 32 gr/sec and it's too low for whole model and 1/6 slice!
I think maybe solver could not recognize slices of periodic correctly!

Thank your in advance!

Last edited by amin.z; September 22, 2014 at 05:39.
amin.z is offline   Reply With Quote

Old   September 22, 2014, 06:45
Default
  #13
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
Where did you compute the mass flow rate?
To not have doubts, compute the mass flow rate not at the interfaces, but in another plane parallel to interface.
Remember that you have to multiply the mass flow rate you read by the number of periodic repeats.

Daniele
ghost82 is offline   Reply With Quote

Old   September 22, 2014, 06:58
Default
  #14
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Quote:
Originally Posted by ghost82 View Post
Where did you compute the mass flow rate?
To not have doubts, compute the mass flow rate not at the interfaces, but in another plane parallel to interface.
Remember that you have to multiply the mass flow rate you read by the number of periodic repeats.

Daniele
I read mass flow at main inlet at left side of model (left side of left rotor) and main outlet at right side of model ( right side of right rotor)
I think the mass flow rate for various slice must be different! Is this correct?
amin.z is offline   Reply With Quote

Old   September 22, 2014, 07:01
Default
  #15
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
It shouldn't...you must have conservation of mass in the domain: every section must have the same mass flow rate, otherwise the solution is not converged.
Moreover, if the fluid is incompressible (constant density in properties) also volumetric flow rate is the same for each section.
I'm not sure but you should have different mass flow rates in the 2 zones (smaller rotor on the right, other zone(s)).

Daniele
ghost82 is offline   Reply With Quote

Old   September 22, 2014, 07:07
Default
  #16
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Quote:
Originally Posted by ghost82 View Post
It shouldn't...you must have conservation of mass in the domain: every section must have the same mass flow rate, otherwise the solution is not converged.
Moreover, if the fluid is incompressible (constant density in properties) also volumetric flow rate is the same for each section.

Daniele
Assume two periodic domains with 2 various angle of periodic! For example first domain 30 degrees and second domain 60 degrees!
Base on mass conservation low, the mass flow rate in first domain should be half of mass flow rate in second domain! ( [mdot 60]= 2 [mdot 30] )
Ok?
amin.z is offline   Reply With Quote

Old   September 22, 2014, 07:12
Default
  #17
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
Yes,
I added later

Quote:
I'm not sure but you should have different mass flow rates in the 2 zones (smaller rotor on the right, other zone(s))
So in your case, I think that if you read the mass flow rate into the right rotor, you have to multiply this value by 15; if you read it on the left side you have to multiply by 6.
total mass flow rate must be equal for the mass conservation.
ghost82 is offline   Reply With Quote

Old   September 22, 2014, 07:15
Default
  #18
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
This is the amazing point! The mass flow rate at left and right domain are equal! Value of both of them is 32gr/sec!

This value is logical for right rotor if multiple in 15! But it's too low for left rotor!
amin.z is offline   Reply With Quote

Old   September 22, 2014, 07:21
Default
  #19
Senior Member
 
ghost82's Avatar
 
Rick
Join Date: Oct 2010
Posts: 1,016
Rep Power: 26
ghost82 will become famous soon enough
mmm..then I don't know...The doubt now is that fluent can return the total mass flow rate yet...
You can test what fluent returns by a simple pipe simulation; you can fix the velocity inlet/pressure outlet, make a full 3d simulation and compute the total mass flow rate.
Then cut the pipe and make it periodic, fix the same v inlet/pressure outlet, recompute mass flow rate and compare the 2 results.
This is to see if fluent reports the total mass flow rate.

Or...create 2 sections into the 2 zones, calculate their area, compute and plot the mean velocity on these surfaces, and calculate the mass flow to compare.

Daniele
ghost82 is offline   Reply With Quote

Old   September 22, 2014, 07:24
Default
  #20
Senior Member
 
amin.z's Avatar
 
Amin
Join Date: Oct 2013
Location: Germany
Posts: 397
Rep Power: 14
amin.z is on a distinguished road
Ok! Tnx for your help dear friend!
If you find any answer for this issue please inform me!
amin.z is offline   Reply With Quote

Reply

Tags
fluent, mesh interfaces, mixing plane

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[snappyHexMesh] Add Mesh Layers doesnt work on the whole surface Kryo OpenFOAM Meshing & Mesh Conversion 13 February 17, 2022 08:34
Mesh interfaces error amin.z FLUENT 0 July 2, 2014 08:20
[ICEM] Generating Mesh for STL Car in Windtunnel Simulation tommymoose ANSYS Meshing & Geometry 48 April 15, 2013 05:24
[snappyHexMesh] Layers:problem with curvature giulio.topazio OpenFOAM Meshing & Mesh Conversion 10 August 22, 2012 10:03
fluent add additional zones for the mesh file SSL FLUENT 2 January 26, 2008 12:55


All times are GMT -4. The time now is 16:15.