UDF paraboloid velocity inlet
Hi, I have to put a velocity profile (fully developed) at the inlet of a 3D case but I never use UDF to define boundaries. The profile is like a paraboloid centered at middle of the pipe. I read the UDF chapter on FLuent doc but there's no 3D case example, only 2D as above (definition of a parabolic profile at inlet):
 #include "udf.h" DEFINE_PROFILE(inlet_x_velocity, thread, position) { real x[ND_ND]; /* this will hold the position vector */ real y; face_t f; begin_f_loop(f, thread) { F_CENTROID(x,f,thread); y = x[1]; F_PROFILE(f, thread, position) = 20.  y*y/(.0745*.0745)*20.; } end_f_loop(f, thread) }  I don't know how to change that in 3D :( . Someone could help me by give the right UDF file format in 3D? Thx a lot :) 
Re: UDF paraboloid velocity inlet
The x vector contains contains x and y position of the cell centroid in 2D, and x,y,z in 3D. So, if you write your paraboloid in the form
z = f(x,y) your x will be the first position (0) of x vector and your y will be the second one (1). So you have to remove the line y = x[1]; and change F_PROFILE(f, thread, position) = 20.  y*y/(.0745*.0745)*20.; in F_PROFILE(f,thread,position) = f(x[0],x[1]); P.S. I'm supposing your pipe axis is along z axis. If you want the code, post the equation of the paraboloid :) Hi ap 
Re: UDF paraboloid velocity inlet
Hi ap ;)
The velocity take several values (derived of the mass flow inlet boundary), the diameter of pipe is 10mm , pipe axis is along Z axis. Here is the mesh for the waterblock (a water flow in a copper shape with a maze) to understand situation (inlet in blue and outlet in red color): http://membres.lycos.fr/roscool/forum/temp/mesh.gif Could you put the code for a 1m/s velocity inlet (mean) for example with a typical poiseuille flow shape (paraboloid)? Thx again ap :) 
Re: UDF paraboloid velocity inlet
I write what I did so you can check it (did it in a hurry :))
I suppose that the origin of reference system is the center of the inlet. If this is not true...translate your mesh with Gambit:) The general paraboloid form is: z = a*x^2 + b*y^2 + c But in our case a=b because it's axisymmetric. The vertex of the paraboloid has z = v_max = 2*v_avg, and it's z = 0 for example in (x=0,y=r). So a = b = v_max/(r^2) c = v_max v_max = 2*v_avg and z = v_max/(r^2) * (x^2+y^2) + v_max In the code i put v_max/(r^2) = coeff. Here's the code. Remember it requires you have the origin of your reference system in the center of the inlet pipe. If you need to change diameter and average velocity, change their values in the corresponding #define. #include "udf.h" #define PIPE_DIAMETER 10.e3 // Set here the diameter of your pipe in meters #define AVG_Z_VELOCITY 1. // Set here the average z velocity at inlet in m/s DEFINE_PROFILE(paraboloid_velocity, thread, position) { real x[ND_ND]; real coeff,r,v_max; face_t f; r = PIPE_DIAMETER/2.; //Calculating radius v_max = 2.*AVG_Z_VELOCITY; //Calculating paraboloid vertex z (max velocity) coeff = v_max/pow(r,2.); begin_f_loop(f, thread) { F_CENTROID(x,f,thread); F_PROFILE(f, thread, position) = coeff*(pow(x[0],2.) + pow(x[1],2)) + v_max; } end_f_loop(f, thread) } Hi and good work ap 
Re: UDF paraboloid velocity inlet
Oki, I understand now how to define each velocity on each face at inlet :) I'll try that soon, I hope it works ;)
Thank you very much ap to help me each time :) 
thank you for detailed discription of udf for paraboloid

Quote:
This is so detailed thank you! Just one thing, F_PROFILE(f, thread, position) = coeff*(pow(x[0],2.) + pow(x[1],2)) + v_max why it's not coeff*(pow(x,2.) + pow(y,2)) + v_max ?? 
Quote:

UDF for inlet temperature
Dear all
I have following UDF for inlet temperature, untill 1300s it takes correct values according to equation, but after 1300s values are higher and not accorrding to equation, like at 1301s it should have value of 405C but in simulation inlet temperature is 621C. I could not find the error in my UDF after lot of try. please check this and guide me. help please. #include"udf.h" DEFINE_PROFILE(inlet_temperature,thread,position ) { face_t f; begin_f_loop(f,thread) { real t = RP_Get_Real("flowtime"); if (t <=1300.0 ) { F_PROFILE(f,thread,position) = 379.13 + 0.0005*t; } else if (1300.0 < t && t <= 1500.0 ) { F_PROFILE(f,thread,position)= 1.04289036878969*pow(10,10)*pow(t,6.0)+ 8.86126436853789*pow(10,7)*pow(t,5.0)3.13621260398811*pow(10,3)*pow(t,4.0)+5.91804640375908*pow(t,3.0)6.27969461279651*pow(10,3)*pow(t,2.0)+ 3.55273415252714*pow(10,6)*t  8.37223405676245*pow(10,8); } else { F_PROFILE(f,thread,position) = 9.51538261322402*pow(10,23)*pow(t,6) + 8.26192751387975*pow(10,18)*pow(t,5)2.85237398505875*pow(10,13)*pow(t,4)+4.97518353700886*pow(10,9)*pow(t,3)4.58733775886876*pow(10,5)*pow(t,2)+ 2.10251137071757*pow(10,1)*t +3.57252192344954*pow(10,2); } } end_f_loop(f,thread) } 
Quote:
Thanks ap for such a detailed description of the UDF. I need a similar one for my project where my average velocity is sinusoidal variation with time and the inlet centre is located at 20 mm from the origin along the y direction and 120 mm along the z direction. Can you please tell me what changes should I make in the UDF program? Please post a quick answer if it is not much of a problem. :) The time varying velocity profile is #include "udf.h"//file that contains definitions for define functions and fluent operations #define PI 3.141592654 DEFINE_PROFILE(in_vela,th,i) { face_t f; real t = CURRENT_TIME; begin_f_loop(f,th) { F_PROFILE(f,th,i) = ((0.086)*(sin(((2*PI/3)*t) + 0.0873)))  0.0075; } end_f_loop(f,th); } 
Hey
My parabola's equation is 0.0064*(x1.25)*(x1.25)0.01 = y Can you please type the code for it Maximum velocity should be 0.01m/s and dimension of 2d rectangle is 250x1000mm 
All times are GMT 4. The time now is 17:46. 