1st  2nd order  convergence
Hi everybody, I'm running a simple 2D simulation. A cylinder (D=1 m) is placed on the ground (contact point in x=0, y=0). Air is entering the domain at 10 m/s. The domain is: [(x=3 to 5), y=0 to 4]. Viscous model: Laminar.
I Run a simulation with the following scheme: [Pressure: Standard; PV Coupling: SimpleC; Momentum: First Order Upwind] and the problem easily finds a convergence (1e06). If I change Momentum to [Second Order Upwind], the continuity residual shows an oscillatory behaviour at around 1e04. Do you have an idea what is this due to? Thank you very much, antonio 
Re: 1st  2nd order  convergence
It's an unsteady problem. Bluff bodies are notoriously difficult to converge, especially cylinders because they lack a defined separation point. If you monitor your forces they'll oscillate as well. Your lift will have a regular oscillation while the drag looks more random, but still has underlying periodicity. If you plot your velocity vectors every so many iterations you'll notice the uneven vortices being shed by the body.
You can try switching to the coupled solver, with 2nd order discretization on flow. Since it's a density based solver, sometimes it can flatten out those oscillations. It's not a sure fix though. I hope this helps. Goodluck, Jason 
Re: 1st  2nd order  convergence
thank you very much. I monitored lift and drag coefficients and they do oscillate quite regurarly. Do you know if there is a way to relate the frequency of the "numerical" oscillation to the physical frequency?

Re: 1st  2nd order  convergence
I've never been able to... I've been asked a few times to do that, but I haven't found a way to do it. If you do find a way can you post it on here?
If you've got the time, I would try running an unsteady solution. You can pull frequencies out of that. Goodluck, Jason 
Re: 1st  2nd order  convergence
I would not waste time trying steady simulation on an unsteady flow problem. Why don't you switch to the unsteady solver which is just a few buttons away?
(1) Choose the secondorder temporal scheme (2) Use SIMPLEC (3) Estimate timestep size based on, say, strouhal number of 0.2 such that would give scores of (>20) time steps in a period (4) Jack up the underrelaxation factors (e.g., 0.9 and 0.95 for pressure and momentum respectively) (5) Monitor and write CD and CL history (6) Use the builtin FFT capability in FLUENT 
All times are GMT 4. The time now is 01:36. 