# k-e or RSM?

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 April 14, 2006, 05:43 k-e or RSM? #1 kevin Guest   Posts: n/a i'm simulating turbulent flow over a circular cylinder, then which model is more appropriate? again, standard or non-equilibrium wall function is better for this kind of problem. any kind of suggestion is sincerely appreciated.

 April 14, 2006, 07:34 Re: k-e or RSM? #2 Mirek Guest   Posts: n/a RSM is better than RNG k-epsilon + non-equilibrium wall function but I prefer k-omega model with enhanced wall treatment called Transitional Flows + Shear Flow Corrections. I tested all turbulence models with all available additional options in Fluent 6.1.22 seeking static pressure distribution on cylinder surface (unsteady flow of course)at mean velocity w=8-32m/s. The turbulence intensity was i=1%, time step about 5e-5s to 5e-6s, y+=1 for enhanced wall treatment (the best for flows with boundary layer separation)and obtained relative error (for static pressure at the back of cylinder) equals to -2.6%. RSM is also good for example RSM + wall bc + non-equilibrium gives relative error (for w=20m/s) equals to -3.1%. I hope it helps you. joy2000 likes this.

 April 14, 2006, 08:14 Re: k-e or RSM? #3 kevin Guest   Posts: n/a thanks for your valuble and detailed reply! it is very helpful of course. by the way, what's the range of ur Re? mine is less than 1e4 right now, but wider is hoped.

 April 14, 2006, 10:02 Re: k-e or RSM? #4 Mirek Guest   Posts: n/a Hello Kevin, it is very easy to calculate. The diameter of my cylinder equals to 12mm so for air Re=6.57e+3 to 2.63e+4. I checked numerical simulation results by myself in my open wind tunnel of low speeds so you can be sure of value of relative errors quoted in my previous message. If you want more information send me e-mail and I'll try to give you more details concerning flow over cylinder. Best regards

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Far CFX 15 March 20, 2014 22:34 ivan_cozza OpenFOAM Running, Solving & CFD 0 June 9, 2009 05:08 Eric Wang CFX 1 January 7, 2009 09:55 Hao FLUENT 0 April 28, 2008 09:14 venkatesh FLUENT 0 October 14, 2005 04:20

All times are GMT -4. The time now is 22:40.

 Contact Us - CFD Online - Top