Turorials on pipe flow
Hi everybody,
I was just wondering if any of you guys know of a tutorial that will guide one in gambit/fluent in making a simple pipe so that I can show the fluid going to fully developed and see the pressure drop as flow goes along the pipe. I thought it was simple to do geometry as in just have a top line and bottom line, however I have been told that I had to do a slice of the circle. I am confused. Does anyone know what he means? 

pipe flow
Thank you Max for a reply.
I have done that tutorial you posted. The pipe I am doing is straight. My supervisor told me that since the pipe is asymmetric I have to do a slice of the pipe. He said if its difficult to do I can do planar and lose considerable marks so am assuming its in 3D. Below is the diagram of what he said I had to do. http://img818.imageshack.us/img818/8...0113142302.jpg He said since its asymmetric I just have to consider the slice as there is no need to consider the whole pipe? 
well, you can draw and simulate:
1 a 2d axisymmetric tube, by drawing 4 points (2 for the axis and 2 for the upper part of the tube), create edges and the surface, mesh it and apply boundary conditions for inlet, outlet, wall and axis; this means drawing half of the tube you have attached and simulate a 2d axisymmetric problem. 2 you can draw and simulate the 3d tube, by drawing a cilinder and assigning boundary conditions, inlet, outlet and wall. 3 you can draw and simulate a slice, for example 1/4 of the tube (3d), by drawing 1/4 of cilinder and assigning boundary conditions, inlet, outlet, wall and periodic (for the 2 rectangular faces); when you mesh the reactangular faces you have to link them. Then in fluent you will set periodic conditions. 4 you can draw and simulate 3d half pipe, by drawing half cilinder and assigning boundary conditions, inlet, outlet, wall and simmetry (to the rectangular face). The simplest one is the 2d axisymmetric problem. Hope that helps Daniele 
Quote:
Is there a guide on how to simulate a slice? If not do you mean draw a cylinder first. Then take away some volume, say 3/4 of it. Then add two rectangles to close the cylinder. Then do boundary conditions. Thank you 
Quote:
Your outline is correct. Create a 3D representation of the 1/4 cylinder (however you are most comfortable with) by closing the two faces (which will be rectangles). Then Mesh it. Then import into fluent and start setting up the problem. 
1 Attachment(s)
Quote:
The less expensive in termes of computational cost is the 2d axisymmetric. If you want to draw 1/4 pipe, in gambit you can draw the full cilinder, then draw a square base prism with one vertex of the base with the same coordinate of the center of one base of the cilinder, with side of the base equal or greater than the radius of the circle, and with prism height equal or greater than the height of the cilinder. After that you can intersect the two volumes and you will obtain the 1/4 cilinder, you don't have to create any further face.. In the mesh tab, link the two rectangular faces, premesh other edges/faces and mesh the volume. Set boundary conditions, export the 3d mesh, start fluent and set your problem. Daniele 
Thank you for replies. I think I now know how its meant to be done. I will try on Monday to get this pipe out of the way. Danielle, that attached thumbnail really helped my understanding.

Hi,
I have another point: Since I am trying to find when the flow becomes fully developed and when a pressure drop occurs, does it mean I have to make a really long pipe or is there another way to do it. Thanks. 
Quote:
for laminar flows: El=0.06*Re le=El*d for turbulent flows: El=4.4*Re^(1/6) le=El*d Where: El=Entrance Length Number (dimensionless) Re=Reynolds number le=length to fully developed velocity profile d=pipe diameter Make sure to draw a pipe longer than the length to fully developed velocity profile. PS: pressure drop occur all along the pipe, even after the flow is fully developed.. Daniele 
Quote:
If you are studying the developing length, then of course you would need a really long pipe. Or is that not the problem? You can simulate only the fully developed portion and not use any entrance length if all you care about is flow after it has become fully developed, is that your problem? 
Quote:
Daniele, thanks for those equations. Really appreciate it. 
Quote:
I have a question, if I use a 2d pipe tube by drawing 4 points (2 for the upper parter and two for the bottom), create edges and the surface, mesh it and apply bounday conditions for inlet, outlet, wall and simulate a 2d planar problem, it is not right, is it? The results are not in agreement with 3d tube. 
Quote:
it is not correct if you simulate it as a 2d planar problem; in 2d planar you are simulating a squaredrectangular base conduct with a depth equal to the value you set in the reference values panel. To compare results with 3d simulation you have to simulate it as 2d axisymmetric. Daniele 
Thank you very much!
Regards, Jing 
Quote:

All times are GMT 4. The time now is 01:26. 