
[Sponsors] 
January 16, 2013, 05:06 
nanoscale treatment in CFD

#1 
New Member
anonymous
Join Date: Jan 2013
Posts: 3
Rep Power: 6 
Dear all,
I am new in the forum and I would appreciate any help about the acceleration process of ironoxide nanoparticles caused by a flow of helium gas in a 1 mm diameter tube . We are interested in getting to know the velocity of the nanoparticles at a fixed length (L) accelerated by the continous phase. Sample input data: Tube diameter = 1 mm Inlet velocity of helium gas = 20 m/s Size of ironoxide nanoparticles (between 10 and 100 nm) inlet mass flow rate of discrete phase = 1mg/min (10.E10 particles aprox.) Can CFD treat the "nanoscale"? Multiphase models implemented in Fluent are going to be used? Which one would be the most suitable?? Any idea about how to do it if possible? ** This is nothing to do with the proper use of an Euler or Lagrange approach as far as multiphase modelling is concerned. My question or doubt (or darkness in which I am involved) is concerning about if the general multiphase models implemented in FLUENT can take into account the interaction forces between the discret & continous phase (or among the different phases) when we are in a nano scale instead of mili/micro scale. I have read something and it seems to be that in case of nano particles, a special phenomenon or motion or force called Brownian appeared, but I know nothing about this effect neither a special treatment to be done when a nanoparticles aree treated. I would need any help to get to know if this application could be treated with a generalpurpose soft like FLUENT or the problem is not as easy like it seems?? Thanks for all in advance and I will be waiting for sb to give some idea. 

January 16, 2013, 08:49 

#2 
Senior Member
cfdnewbie
Join Date: Mar 2010
Posts: 557
Rep Power: 13 
The navierstokes equations are derived assuming continuum assumption (Knudsennumber > 0). If your flow has a high Knudsen number, the validity of this assumption becomes weak, and any code solving the navier stokes equations will get into trouble. There are some extensions to rarefied or extended gas dynamics, but I doubt that they have been included in a commercial solver, in fact, most of this topic is still very current research.


January 16, 2013, 10:16 

#3 
Senior Member
Alex
Join Date: Jun 2012
Location: Germany
Posts: 1,411
Rep Power: 23 
Fluent comes with a boundary condition suitable for extending the applicability of the NSequations to about Kn=0.1.
See "slip boundary formulation for low pressure gas systems" in the fluent documentation. 

January 16, 2013, 13:09 

#4 
Senior Member
Join Date: Dec 2011
Location: Madrid, Spain
Posts: 134
Rep Power: 8 
Hi, I don't see such problem. The nano particles are transported by a continuous phase (helium), which is not rarefied, so that NS holds perfectly.
The transport of nano particles can be modelled by seeding the flow with a discrete number of particles and tracking their trajectories individually (Lagrangian approach) or using an Eulerian formulation, which also holds if the nano particles are diluted in the main gaseous phase. This will allow you to obtain the velocity of the particles. As far as I know, FLUENT allows you to include the Brownian motion effect. I would suggest that you calculate the Stokes number of the particles beforehand. If it is sufficiently small the particles will accelerate right away and attain the velocity of the gaseous stream. Otherwise, if St~1 or higher, the inertia of the particles is not negligible. Cheers, Michujo. 

January 16, 2013, 17:37 

#5 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 13,186
Rep Power: 102 
Hi JGG:
You asked me to comment on this thread but the comments here already are a good summary of the issues to consider. Other than to say that if you are looking at the length by which the particle accelerate to flow velocity  this is easily worked out through the stokes number and you do not need CFD for that. 

January 17, 2013, 06:00 

#6 
Senior Member
Alex
Join Date: Jun 2012
Location: Germany
Posts: 1,411
Rep Power: 23 
I disagree with that. If the Knudsen number evaluated from the mean free path of the fluid and the characteristic length of the particles is high, the NSequations are no longer valid.


January 17, 2013, 08:36 

#7  
Senior Member
Join Date: Dec 2011
Location: Madrid, Spain
Posts: 134
Rep Power: 8 
Quote:
Out of curiosity I calculated the Knudsen numbers of the gas relative to the tube diameter (1 mm) and to the particles diameter (1e7 to 1e8 m). The mean free path of the gas is calculated for p=1 bar and T=273 K. I get: Kn_tube ~ 2e4 Kn_particles ~ 2e1 to 2e0 In light of these results I think we can say that NS hold for the gas, since the Kn relative to the tube characteristic dimension is small. However, for the particles it is not. Do the concept of Stokes number or drag force still hold for this case, where the particles are travelling through the interstices of the helium gas particles? How would you compute the drag force of the solid particles then? Thanks, Michujo. 

January 17, 2013, 09:14 

#8  
Senior Member
Alex
Join Date: Jun 2012
Location: Germany
Posts: 1,411
Rep Power: 23 
Quote:
Quote:
But it should still be possible to calculate the drag through some kind of algebraic expression. I havent done any research on this particular topic, but i am sure that there exists literature about it. 

January 28, 2013, 17:45 

#9 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 13,186
Rep Power: 102 
You definitely should check the Knudsen number is in the range where the NS equations apply. If that is OK, then you should check the stokes number of your particles and work out the terminal velocity/range of the particles and see if that is much smaller than your region of interest. For nanoparticles this is usually the case.


Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Scale meshing ANSYS ICEM CFD  Giannis191919  ANSYS Meshing & Geometry  0  September 30, 2011 05:47 
ASME CFD Symposium, Atlanta, July 2001  Chris R. Kleijn  Main CFD Forum  0  September 13, 2000 04:48 
ASME CFD Symposium, Atlanta, July 2001  Chris R. Kleijn  Main CFD Forum  0  August 21, 2000 04:49 
PC vs. Workstation  Tim Franke  Main CFD Forum  5  September 29, 1999 15:01 
public CFD Code development  Heinz Wilkening  Main CFD Forum  38  March 5, 1999 12:44 