CFD Online Logo CFD Online URL
Home > Forums > Main CFD Forum

fixed pressure

Register Blogs Members List Search Today's Posts Mark Forums Read

LinkBack Thread Tools Display Modes
Old   August 4, 1999, 02:38
Default fixed pressure
Posts: n/a
I am working on incomressible fluid flow problem with the following specifications. Inlet B.C. :fixed velocity boundary condition at 6 m/s with turbulence intensity of 2% OUTLET B.C : fixed pressure boundary condition at 0 pressure with the same turbulence. Problem: At the outlet there is INFLOW. Any Explanation. Geometry : Like Heat Exchanger Baffles are placed in the flow domain.
  Reply With Quote

Old   August 4, 1999, 04:07
Default Re: fixed pressure
John C. Chien
Posts: n/a
(1). You need to find out the real flow pattern first. (2). The flow pattern is determined by your problem specification, which is a strong function of the problem geometry. (3). It is likely that the outlet is not placed far downstream and there is a flow separation there. (4). So, move the outlet condition further downstream to avoid the complication first. (5). In the pressure-based solver, the solution can also run into reverse flow during iteration. But it should disappear by the time the solution converges, if the exit boundary condition is placed properly further downstream.
  Reply With Quote

Old   August 4, 1999, 08:27
Default Re: fixed pressure
Jin Wook LEE
Posts: n/a
It is best to place the outlet far downstream, but sometimes it is impossible. In that case, you should check the possibility of reverse flow in the real flow system. For special cases, inflow through the boundary, including outlet, is possible correct solution. In that case, outlet is not a real outlet but a mixed inflow/outflow boundary.

Hoping that it might be helpful to you.

Sincerely, Jin Wook LEE
  Reply With Quote

Old   August 4, 1999, 10:21
Default Re: fixed pressure
Biao Zhou
Posts: n/a
The real flow pattern is dependent on the specific geometry and sometime reverse flow from outlet is expected for some engineering application, for example, some burner.

You also can check if your boundary is set correctly with the following step:

(1) calculate a short case; (2) calculate a long case; (3) compare the presure and velocity fields between the two cases for some specified cross-sections. If the boundary is right, then the results should be same or very closed.

  Reply With Quote

Old   August 6, 1999, 00:34
Default Re: fixed pressure
clifford bradford
Posts: n/a
for your inlet you need 2 bc other than the turbulence intensity. also as Jin said the reversed flow may be physically realistic in which case your code needs to check whether the boundary is inflow or outflow if it is outflow your one bc is adequate if it is inflow you must then specify another bc(?).another option may be to use nonreflecting bc at the exit which may allow the reversed flow.
  Reply With Quote


Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
Calculation of the Governing Equations Mihail CFX 7 September 7, 2014 06:27
Pressure BC for combustion chamber Giuki FLUENT 1 July 19, 2011 11:35
Setting pressure and velocity in inlet Asghari FLUENT 5 September 22, 2006 13:23
Neumann pressure BC and velocity field Antech Main CFD Forum 0 April 25, 2006 02:15
How to realize fixed pressure in my codes? Leon Phoenics 2 March 16, 2003 01:23

All times are GMT -4. The time now is 03:33.