
[Sponsors] 
March 18, 2013, 05:53 
Opening Boundary Condition

#1 
New Member
Xingyuan Chen
Join Date: Feb 2011
Location: Darmstadt
Posts: 10
Rep Power: 8 
Hello,
I want to simulate a flow domain having such a boundary, where the pressure value is known, and the fluid can flow into or out of the domain at this boundary. It means this boundary can be an inlet or outlet boundary conditions with fixed pressure value. I am wondering how to treat the pressure and velocity on this boundary, since the flow direction can be both in and out. Is it correct that I treat the boundary as normal inlet pressure static BC when the fluid flows in and as normal outlet pressure static BC when the fluid flows out? I have found such a boundary condition in the software CFX, which is called Opening Boundary Condition. I am wondering the principle and mathematical background of this boundary condition. However, I could not find any details in the CFX manual. Could anyone tell me some papers or books about this kind of boundary condition? Thanks. 

March 18, 2013, 09:00 

#2 
Senior Member
Filippo Maria Denaro
Join Date: Jul 2010
Posts: 3,004
Rep Power: 35 
I don't understand your flow problem...what about your computational domain and the forces driving the main flow?


March 18, 2013, 09:30 

#3 
New Member
Xingyuan Chen
Join Date: Feb 2011
Location: Darmstadt
Posts: 10
Rep Power: 8 
There is a movable part in the domain, which makes the volume of the whole domain changeable. When the volume decreases, the fluid flows out through this 'opening boundary'. When the volume increases, the fluid flows in through this 'opening boundary'.


March 18, 2013, 11:00 

#4 
Senior Member
Filippo Maria Denaro
Join Date: Jul 2010
Posts: 3,004
Rep Power: 35 
if the flow is modelled as incompressible, you can set also some bc. on the velocity instead of pressure, for example setting a vanishing second derivative. If the flow is fully compressible, you need some more complex nonreflecting bc.s.


March 18, 2013, 13:54 

#5  
New Member
Xingyuan Chen
Join Date: Feb 2011
Location: Darmstadt
Posts: 10
Rep Power: 8 
Quote:
I am simulating an incompressible fluid. But I wondering why we can set a vanishing second derivative of the velocity as a boundary condition. What is the physical meaning of it? 

March 18, 2013, 14:01 

#6  
Senior Member
Filippo Maria Denaro
Join Date: Jul 2010
Posts: 3,004
Rep Power: 35 
Quote:
For incompressible flows you can prescribe either velocity or pressure to have the problem well posed. What the physics says you about the inlet/outle? I don't think you know the velocity profile or the pressure gradient in time ... therefore some "free condition" on the velocity is better to let the flow to go in and out. You cna also prescribe some fixed pressure value if you have two large tank at the end... What is really required is that you enforce correctly the divergencefree constraint 

March 19, 2013, 00:05 
Open boundary condition

#7  
Senior Member
Jonas T. Holdeman, Jr.
Join Date: Mar 2009
Location: Knoxville, Tennessee
Posts: 109
Rep Power: 11 
Quote:


March 19, 2013, 07:11 

#8  
Senior Member
andy
Join Date: May 2009
Posts: 129
Rep Power: 9 
Quote:
I am not familiar with the current set of CFX boundary conditions and so can offer little help here. 

March 19, 2013, 07:14 

#9  
New Member
Xingyuan Chen
Join Date: Feb 2011
Location: Darmstadt
Posts: 10
Rep Power: 8 
Quote:
Do you also know the mathematical description of such boundary condition? 

March 19, 2013, 07:20 

#10  
New Member
Xingyuan Chen
Join Date: Feb 2011
Location: Darmstadt
Posts: 10
Rep Power: 8 
Quote:


March 19, 2013, 11:08 
open boundary condition

#11  
Senior Member
Jonas T. Holdeman, Jr.
Join Date: Mar 2009
Location: Knoxville, Tennessee
Posts: 109
Rep Power: 11 
I thought about this a little more and did a Google search on open boundary conditions. Most of the hits seemed to involve atmospheric or oceanic flows and radiation, and the methods seem mostly heuristic. My examples involve a specific method, but perhaps there are general considerations.
Quote:
In my case, the equations for the nodes on the exit face are only partially assembled because here are no elements outside. This may be called a "do nothing" boundary condition. I am not sure why it works, but it does. Any mathematicians out there? This open condition has further utility. Consider flow over a cylinder. One usually uses a mesh wide enough that the effects of truncation of the space might be neglected. Usually one has to compromise between computational work and accuracy. But suppose you leave the top and bottom of the mesh open as well. Then the fluid could expand outside the mesh near the cylinder, and then reentering downstream, reducing the influence of truncation without additional work. This is shown for Re=50 in the figure, where the top, bottom and right end are open, but net flow through the top and bottom constrained to be zero. 

March 19, 2013, 17:46 

#12 
Senior Member
Join Date: Aug 2011
Posts: 251
Rep Power: 8 
Yes zero gradient is an option, from a physical point of view it indicates that the velocity is the same on each side of the boundary. A better one is, as Filippo stated it, second derivative of the velocity =0. In this case you specify that you want to keep the same gradient of the velocity on each side of the boundary. This BC is less constraining for the solution.


Tags 
boundary condition 
Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Opening boundary condition  sicfred  FLUENT  3  May 11, 2012 06:46 
Fluent Boundary Condition for Opening  rippert42  FLUENT  11  November 9, 2011 13:06 
External Radiation Boundary Condition (Two sided wall), Grid Interface  CFD XUE  FLUENT  0  July 8, 2010 06:49 
CFX Solver : Sudden crash  HervĂ©  CFX  2  June 16, 2008 06:40 
boundary condition set for opening  Hellen  Main CFD Forum  7  June 29, 2005 09:21 