CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > General Forums > Main CFD Forum

What is blockage ratio?

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree3Likes
  • 1 Post By Bazinga
  • 1 Post By Bazinga
  • 1 Post By LuckyTran

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   December 23, 2016, 18:16
Default What is blockage ratio?
  #1
New Member
 
Sarah M
Join Date: Oct 2016
Posts: 8
Rep Power: 9
Fun_Doge is on a distinguished road
Hi,

I am relatively new when it comes to CFD analysis and I have stumbled across this thing called blockage ration. Since I haven't found any useful information about it I was wondering if someone could give me an explanation.

What I know so far is that it is the ratio between the body/geometry and the height of the domain.

Now, let us say that we have a circular cylinder. If we have the same height for the circle but increase the heigh of the domain (thus getting a lower ratio), what impact does it have on the flow? Less pressure maybe?

Thanks!
Fun_Doge is offline   Reply With Quote

Old   December 24, 2016, 04:31
Default
  #2
Senior Member
 
Join Date: Jun 2012
Location: Germany, Bochum
Posts: 230
Rep Power: 15
Bazinga is on a distinguished road
It is usually defined as the projected area of the structure in flow direction to the cross sectional area of the domain around the structure.

Usually you wanna go below 3% of blockage ratio. Otherwise you might introduce an artificial acceleration of the flow - remember the continuity equation.

I am guessing that if the velocity is increased before the separation at the cylinder, the pressure will be smaller (more suction). It is a common problem in wind tunnel experiments, where the domain is fixed. Here, they use mathematical approaches to correct the pressure if the blockage is too high.
flotus1 likes this.
Bazinga is offline   Reply With Quote

Old   December 24, 2016, 04:45
Default
  #3
Super Moderator
 
flotus1's Avatar
 
Alex
Join Date: Jun 2012
Location: Germany
Posts: 3,396
Rep Power: 46
flotus1 has a spectacular aura aboutflotus1 has a spectacular aura about
This. With a small addendum: in some experiments the blockage ratio is fixed parameter and should not be minimized. Like for example the flow over an obstacle confined by walls with a fixed position.
flotus1 is offline   Reply With Quote

Old   December 26, 2016, 07:01
Default Thanks
  #4
New Member
 
Sarah M
Join Date: Oct 2016
Posts: 8
Rep Power: 9
Fun_Doge is on a distinguished road
Thanks for the help!
Fun_Doge is offline   Reply With Quote

Old   October 31, 2019, 08:13
Default
  #5
Member
 
Rasmus Iwersen
Join Date: Jan 2019
Location: Denmark
Posts: 81
Rep Power: 8
Rasmusiwersen is on a distinguished road
Quote:
Originally Posted by Bazinga View Post
It is usually defined as the projected area of the structure in flow direction to the cross sectional area of the domain around the structure.

Usually you wanna go below 3% of blockage ratio. Otherwise you might introduce an artificial acceleration of the flow - remember the continuity equation.

I am guessing that if the velocity is increased before the separation at the cylinder, the pressure will be smaller (more suction). It is a common problem in wind tunnel experiments, where the domain is fixed. Here, they use mathematical approaches to correct the pressure if the blockage is too high.
Hi Bazinga,

I have a follow up question to your statement. Will the articifial acceleration of the flow not only occur if the boundary condition on the walls parallel to the flow direction are (semi)impermeable? I mean if you e.g. have a symmetryPlane on the front/back patches (i.e. not bottom and top patches), the flow wont "feel" the presence of walls, and therefore not contract. Hence, blockage effect wont be a problem in this case. I guess that is the point of symmetryPlanes, right?

Anyway, thank you for your answer to the question. It still helps people some years later

/Rasmus
Rasmusiwersen is offline   Reply With Quote

Old   October 31, 2019, 09:25
Default
  #6
Senior Member
 
Join Date: Jun 2012
Location: Germany, Bochum
Posts: 230
Rep Power: 15
Bazinga is on a distinguished road
Dear Rasmus,

boundary layer effects and blockage effects are two separate topics.

If the blockage ratio is too high, acceleration of the flow might appear. This can happen even with symmetry conditions at top/bot/front/back. Imagine a very small cross-section compared to your object. Even with symmetry, the velocity needs to accelerate to compensate for the small area (continuity).

However, symmetry might help to prevent effects due to boundary layers. For example, let's say you have a wing through the whole span of your domain (or wind tunnel). When you want to predict the drag coefficient you should probably consider that the velocity close to the wall is reduced. Hence, if you estimate the drag coefficient by normalization using the undisturbed inflow velocity in the center you introduce an error by not accounting for the decelerated flow at the wall. Symmetry conditions in CFD help to overcome the issue.

Best regards
lvl99 likes this.
Bazinga is offline   Reply With Quote

Old   October 31, 2019, 09:41
Default
  #7
Member
 
Rasmus Iwersen
Join Date: Jan 2019
Location: Denmark
Posts: 81
Rep Power: 8
Rasmusiwersen is on a distinguished road
Hi again,

Thank you for your quick response! Didn't see that coming. I really appreciate it!

Quote:
Originally Posted by Bazinga View Post
Dear Rasmus,

boundary layer effects and blockage effects are two separate topics.

If the blockage ratio is too high, acceleration of the flow might appear. This can happen even with symmetry conditions at top/bot/front/back. Imagine a very small cross-section compared to your object. Even with symmetry, the velocity needs to accelerate to compensate for the small area (continuity).
I get the continuity reference, although i think I am confused as to what the symmetryPlane condition then is. Perhaps i mix it with the "empty" boundary condition? Will blockage be the same issue if "empty" boundary conditions apply? Hence the 100 % permeable boundary condition.
My line of thought is that in reality blockage is practically =0, as there is no "domain width" in the ocean for example. In the model however, there will always be some sort of blockage since the numerical domain is restricted to a certain width. I am looking for a boundary condition that allow the flow to pass through a cross section without streamlines being contracted as consequence of that exact boundary.

Quote:
Originally Posted by Bazinga View Post
However, symmetry might help to prevent effects due to boundary layers. For example, let's say you have a wing through the whole span of your domain (or wind tunnel). When you want to predict the drag coefficient you should probably consider that the velocity close to the wall is reduced. Hence, if you estimate the drag coefficient by normalization using the undisturbed inflow velocity in the center you introduce an error by not accounting for the decelerated flow at the wall. Symmetry conditions in CFD help to overcome the issue.

Best regards
Just to be sure, what you say is that if i apply symmetry conditions to the boundary in this instance, it helps by not having a reduced velocity at that exact boundary (the values at the boundary are rather equal to the values in the cells near to the wall), leading to a uniform free stream velocity? Hence, the presence of boundaries does not affect the solution. Correct?
Rasmusiwersen is offline   Reply With Quote

Old   October 31, 2019, 10:46
Default
  #8
Senior Member
 
Lucky
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 5,654
Rep Power: 65
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
The starting point is either a symmetry BC or slip wall as a starting point. If the artificial boundary is far enough away then the blockage ratio is small and the influence of the boundary can be negligible. This is fundamental and should not be overlooked.


What you're looking for is part of the family of so-called freestream boundary condition or farfield boundary conditions. These characteristic BC types allow semi-arbitrary constraints on the flow variables at the boundary as long as they relax to the far field conditions (pressure, velocity, Mach number, etc.). Briefly, they solve a characteristic value problem (i.e. Riemann invariants) to determine what the flow variables should be applied to the BC in order to approach the far field or freestream condition.


But this approach is only a bandaid. It is not the be all end all. There still will be artificial blockage. You still need to make sure the BC is far enough away.
lvl99 likes this.
LuckyTran is offline   Reply With Quote

Old   October 31, 2019, 10:54
Default
  #9
Member
 
Rasmus Iwersen
Join Date: Jan 2019
Location: Denmark
Posts: 81
Rep Power: 8
Rasmusiwersen is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
The starting point is either a symmetry BC or slip wall as a starting point. If the artificial boundary is far enough away then the blockage ratio is small and the influence of the boundary can be negligible. This is fundamental and should not be overlooked.


What you're looking for is part of the family of so-called freestream boundary condition or farfield boundary conditions. These characteristic BC types allow semi-arbitrary constraints on the flow variables at the boundary as long as they relax to the far field conditions (pressure, velocity, Mach number, etc.). Briefly, they solve a characteristic value problem (i.e. Riemann invariants) to determine what the flow variables should be applied to the BC in order to approach the far field or freestream condition.


But this approach is only a bandaid. It is not the be all end all. There still will be artificial blockage. You still need to make sure the BC is far enough away.
Hello,

I see. I think I've got a different picture of the symmetryPlane boundary condition and when it is applied now. Consequently i think i get the reason for why it too poses a boundary condition disturbance to the flow and forces.
Thank you both for taking you time to answer my question.

Have a great day!

/Rasmus
Rasmusiwersen is offline   Reply With Quote

Reply

Tags
blockage ration, cfd, meshing

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Problem with divergence TDK FLUENT 13 December 14, 2018 07:00
Blockage ratio Saketh#2012 FLUENT 1 June 27, 2014 22:35
pressure eq. "converges" after few time steps maddalena OpenFOAM Running, Solving & CFD 69 July 21, 2011 08:42
diesel spray combustion equivalence ratio usker Siemens 12 March 1, 2008 07:09
Problem of Turbulent Viscosity Ratio Limited David Yang FLUENT 3 June 3, 2002 07:13


All times are GMT -4. The time now is 05:50.