
[Sponsors] 
April 29, 2013, 06:24 
groovyBC problem with radiation boundary

#1 
Senior Member
Mohammad Shakil Ahmmed
Join Date: Oct 2012
Location: AUS
Posts: 132
Rep Power: 7 
Hi,
I am trying to use the following boundary condition with groovyBC: k*dT/dn = h*(TTinf)+(sigma*emissivity)*(T^4Tinf^4) where, k= thermal conductivity=5.91 [W/mK] h = heat transfer coefficient =12.4 [W/m2K] Tinf =300K emissivity=0.775 What happens in my case is that the simulation diverges after some time steps. Does anyone implemented this boundary condition in OpenFOAM? or any idea how to solve this problem??? Thanks in advance. 

April 29, 2013, 11:18 

#2  
Assistant Moderator
Bernhard Gschaider
Join Date: Mar 2009
Posts: 4,013
Rep Power: 43 
Quote:
__________________
Note: I don't use "Friend"feature on this forum out of principle. Ah. And by the way: I'm not on Facebook either. So don't be offended if I don't accept your invitation/friend request Last edited by gschaider; April 29, 2013 at 14:01. Reason: Missing word 

May 3, 2013, 08:59 

#3 
Senior Member
Mohammad Shakil Ahmmed
Join Date: Oct 2012
Location: AUS
Posts: 132
Rep Power: 7 
Thanks gschaider,
yes it's because of time steps. When I minimize the time steps the problem solved 

May 4, 2013, 07:12 

#4 
Assistant Moderator
Bernhard Gschaider
Join Date: Mar 2009
Posts: 4,013
Rep Power: 43 
OK. You can stabilize it by implementing a mixed boundary with TInf as the Dirichletterm (that would avoid overshooting). The fractionExpression is to be calculated according to the heatflux
__________________
Note: I don't use "Friend"feature on this forum out of principle. Ah. And by the way: I'm not on Facebook either. So don't be offended if I don't accept your invitation/friend request 

August 31, 2013, 07:22 

#5  
Senior Member

Quote:
Can you please explain this a little bit more? How can I avoid overshooting? What does fractionExpression has to do with this? Thank you, Mojtaba
__________________
Learn OpenFOAM in Persian for free, And ask your questions here. Complex Heat & Flow Simulation Research Group If you can't explain it simply, you don't understand it well enough. "Richard Feynman" 

September 2, 2013, 18:19 

#6  
Assistant Moderator
Bernhard Gschaider
Join Date: Mar 2009
Posts: 4,013
Rep Power: 43 
Quote:
The thing is that an infinitely fast heat transfer it is basically a Dirichlet condition. For a "very fast" HT it is something in between a Dirichlet and a Neuman. If you implement a pure Neuman you get the overshoots in this case (just sit down with pen an paper, discretize a boundary cell with a big temperatur difference, a big heat transfer coeff and a big timestep and you'll see the overshoot). You can get rid of this by making the timestep very small or by using a mixed conditon
__________________
Note: I don't use "Friend"feature on this forum out of principle. Ah. And by the way: I'm not on Facebook either. So don't be offended if I don't accept your invitation/friend request 

October 13, 2013, 05:44 
how to implement radiation BC...

#7  
Senior Member
Alex
Join Date: Oct 2013
Posts: 336
Rep Power: 14 
Quote:
Could you, please, help me with the implementation of this boundary condition using groovyBC? I'm new in it and some days ago I was trying to solve a problem where I had to use exactly that BC but I didn't know how to do that using groovyBC. I have been reading and looking for more info about the use of groovyBC but I'm stuck with this problem... Thanks in advance!
__________________
Web site where I present my Master's Thesis: foamingtime.wordpress.com The case I talk about in this site was solved with chtMultiRegionSimpleFoam solver and involves radiation. Some basic tutorials are also resolved step by step in the web. If you are interested in these matters, you are invited to come in! 

October 13, 2013, 21:08 

#8 
Senior Member
Mohammad Shakil Ahmmed
Join Date: Oct 2012
Location: AUS
Posts: 132
Rep Power: 7 
Hi sorry for the late response. For implementing this boundary condition you can do as follows:
type groovyBC; variables "h=10;k=50;sigma=5.6e7;E=0.7;Tinf=300;"; gradientExpression "h/k*(TTinf)+(sigma/k)*E*(TTinf)*(TTinf)*(TTinf)*(TTinf)"; fractionExpression "0"; values are given as dummy. Use your time step smaller. Its works for me. cheers 

October 14, 2013, 08:28 

#9 
Senior Member
Alex
Join Date: Oct 2013
Posts: 336
Rep Power: 14 
Thank you Mohammad!
Now I realised that maybe this is not exactly what I was looking for because in my case the radiation heat flux is known. Therefore, maybe i shoud make some change to adapt your boundary conditions to my case. Anyway, thank you so much! Your help was very useful to me and it helped me to understand a little how groovyBC works! Although I still need to practise quite a lote to learn the power of groovyBC... Cheers!
__________________
Web site where I present my Master's Thesis: foamingtime.wordpress.com The case I talk about in this site was solved with chtMultiRegionSimpleFoam solver and involves radiation. Some basic tutorials are also resolved step by step in the web. If you are interested in these matters, you are invited to come in! 

October 18, 2013, 01:54 

#10 
Member
Alexander
Join Date: Mar 2009
Posts: 47
Rep Power: 10 
Apropos, you can solve the nonlinear equation k*dT/dn = h*(TTinf)+(sigma*emissivity)*(T^4Tinf^4) concerning T by Newton method (few iterations are enough). And for better stability use a relaxation: Tnew=alpha*T+(1alpha)*Told where alpha < 1. But it is necessary to rewrite k*dT/dn as k/delta*(TTinner). I do not know how to find Tinner exactly but something like that can be helpful: Tinner = TwallsnGrad(T)*mag(delta()).


June 29, 2015, 12:29 

#11  
Member
Colli, Alejandro
Join Date: Jan 2014
Posts: 49
Rep Power: 5 
Quote:
Thank you 

June 29, 2015, 16:33 

#12  
Member
Alexander
Join Date: Mar 2009
Posts: 47
Rep Power: 10 
Quote:
f(T) = k*dT/dn  h*(TTinf)(sigma*emissivity)*(T^4Tinf^4) You should solve the equation: f(T) = 0. dT/dn should be rewritten as k*dT/dn = k/delta*(TTinner), where Tinner = TwallsnGrad(T)*mag(delta()), Twall and snGrad(T) are from previous time step. You should calculate df/dT: df/dT = k/delta  h  4*(sigma*emissivity)*T^3 Please check the signs  I am not sure Hope this helps you. 

June 30, 2015, 11:03 

#13  
Member
Colli, Alejandro
Join Date: Jan 2014
Posts: 49
Rep Power: 5 
Quote:
Do you know how to control convergence of BC?. My problem has nonlinear bc and takes 200 to 4000 (depending of parameters) iterations (when Newton's method is used). But I do not know how to control the convergence of bc, only modifying simple.correctNonOrthogonal() loop in laplacianFoam by trial and error. 

June 30, 2015, 15:15 

#14  
Member
Alexander
Join Date: Mar 2009
Posts: 47
Rep Power: 10 
Quote:


Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
natural convection  mehrdadeng  CFX  10  February 25, 2011 06:25 
problem about periodic boundary condition in Fluent  winnawinna  FLUENT  0  December 29, 2010 00:32 
External Radiation Boundary Condition (Two sided wall), Grid Interface  CFD XUE  FLUENT  0  July 8, 2010 06:49 
Radiation problem  mesumon203  FLUENT  0  June 21, 2010 04:31 
Convective Heat Transfer  Heat Exchanger  Mark  CFX  6  November 15, 2004 16:55 