|
[Sponsors] |
March 10, 2016, 10:12 |
kOmegaSST Transition Model in OF 3.0.1
|
#1 |
Senior Member
Alex
Join Date: Jan 2014
Posts: 126
Rep Power: 12 |
Hi there,
I am currently doing some analysis of airfoils and I have read about the transition formulation for the OF kOmegaSST model here: http://www.tfd.chalmers.se/~hani/kur...transition.pdf Unfortunately, the tutorial is written for OF 2.0 while I am running 3.0.1. I can't compile the turbulence model because some data simply isn't there or has significantly changed during the updates. Thus, I have 2 questions: 1. Does a newer version of this transition model implementation exist somewhere? 2. In what way is the kkLOmega-model similar to this and is it possible to generate this transition model from the kkLOmega and kOmegaSST source files? I am thankful for any kind of help! Cheers Alex |
|
March 17, 2016, 20:27 |
kOmegaSST Transition Model in OF 3.0.x
|
#2 |
New Member
Helio Villanueva
Join Date: Apr 2013
Location: Brazil
Posts: 14
Rep Power: 13 |
Just did and you can find the code here: https://github.com/HelioVillanueva/helio-3.0.x.git
I used the material of prof. Hakan Nillson and Ayyoob Zarmehri and tried to change as little as possible starting from the kOmegaSST. What significantly changed was the transitionDict file which is no longer needed. The freeStreamU parameter is provided inside the turbulenceProperties and has a standard value of 5.4 (used in the flatPlate tutorial). The code seems to work as expected for the tutorial presented in the report. Please, help validate the code and share your experience with it. The tutorial case reported is also in the link above (flatPlate). Note that to plot the last figure of the report in paraview I used the Plot Over Line filter with the points (0.05,1e-6,0.05) and (2.95,1e-6,0.05) in the internal mesh. To use this code clone the repository and copy the contents of helio-3.0.x to your OpenFOAM user folder. Then compile the 'findroot' codes in src/findroot by Code:
wmake libso For the turbulence models, just run the Allwmake scrip in src/TurbulenceModels and it should compile well. Last edited by HelioVillanueva; March 18, 2016 at 07:04. Reason: I moved the findroot from run/ to src/. To me it gets the user folder better organized... |
|
March 20, 2016, 06:36 |
|
#3 |
Senior Member
Alex
Join Date: Jan 2014
Posts: 126
Rep Power: 12 |
Hi Helio,
thank you very much for the implementation of the code for OF 3.0.1! I will do extensive testing in the following days and report back to you how well it compares to CFX transition data. Cheers Alex |
|
May 12, 2016, 15:50 |
|
#4 |
Senior Member
Join Date: Mar 2016
Posts: 133
Rep Power: 10 |
Hi Elio!
How do you have calculated Ret to inlet? |
|
May 13, 2016, 10:23 |
|
#5 |
New Member
Helio Villanueva
Join Date: Apr 2013
Location: Brazil
Posts: 14
Rep Power: 13 |
Hi!
You can find in the report by prof. Hakan Nillson (http://www.tfd.chalmers.se/~hani/kur...transition.pdf, same link Alex pointed) on page 22 that the inlet condition for Ret was calculated using eqs 3.24-3.28 on page 16. You can also find these eqs on page 14 (eqs 24-25) in Malan, Paul, Keerati Suluksna, and Ekachai Juntasaro. "Calibrating the γ-Reθ transition model for commercial cfd." 47th AIAA Aerospace Sciences Meeting. 2009. |
|
May 18, 2016, 06:20 |
|
#6 |
Senior Member
Join Date: Mar 2016
Posts: 133
Rep Power: 10 |
Hi Helio, i have a problem in compilation. For compilation in findroot all ok, but when i run allwmake from directory bin a i type:
wmake $targetType ../findroot/ the terminal is closed and i can't conclude compilation. Could you help me to resolve this error? |
|
May 18, 2016, 08:07 |
compilation kOmegaSST Transition Model in OF 3.0.x
|
#7 |
New Member
Helio Villanueva
Join Date: Apr 2013
Location: Brazil
Posts: 14
Rep Power: 13 |
Hi giammy92!
It was a little confusing to have to compile the findroot folder first and then the turbulence models, so I included in the Allwmake a line to compile it automatically. In summary after cloning the repository and copying the files to your OF user folder, you just have to run the Allwmake in a terminal to compile all. Could you please try it again and see if it works. |
|
May 18, 2016, 08:30 |
|
#8 |
Senior Member
Join Date: Mar 2016
Posts: 133
Rep Power: 10 |
I have proper follow instructions in your Allwmake file:
#!/bin/sh cd ${0%/*} || exit 1 # Run from this directory # Parse arguments for library compilation targetType=libso . $WM_PROJECT_DIR/wmake/scripts/AllwmakeParseArguments set -x wmake $targetType ../findroot/ #wmake $targetType turbulenceModels wmake $targetType incompressible wmake $targetType compressible but when i arrive to type wmake $targetType ../findroot/ the terminal is closed inexplicably. |
|
May 18, 2016, 10:21 |
|
#9 |
New Member
Helio Villanueva
Join Date: Apr 2013
Location: Brazil
Posts: 14
Rep Power: 13 |
Hi giammy92!
Sorry but I don't actually know why it is happening. If you managed to compile the findroot separately (going to the folder and wmake libso there), you could try to skip this line of the Allwmake and jump to the compilation of the models. Please see if it works. |
|
May 18, 2016, 13:48 |
|
#10 |
Senior Member
Join Date: Mar 2016
Posts: 133
Rep Power: 10 |
sorry helio, could show me how to compile a turbulence model? i need SST transition gamma-theta
|
|
May 19, 2016, 08:53 |
|
#11 |
New Member
Helio Villanueva
Join Date: Apr 2013
Location: Brazil
Posts: 14
Rep Power: 13 |
It should be as simple as open a terminal in yourOFuser-3.0.x/src/TurbulenceModels and run the Allwmake (like this ./Allwmake). I assumed that this way didn't work for you since you were typing line by line of the Allwmake, so if this is really the case, type the lines and skip the one for the findroot (but this way you have to compile findroot separately before). The commands to compile the turbulence models are
Code:
wmake $targetType incompressible wmake $targetType compressible |
|
June 8, 2016, 09:57 |
|
#12 |
Senior Member
Join Date: Mar 2016
Posts: 133
Rep Power: 10 |
Hi Helio! i have compiled with Allwmake in src/turbulencemodels and it seems that has compiled with Allwmake but in the end tell me that miss findRoot.H:
gianmichele@gianmichele-K52Jc:~/OpenFOAM/gianmichele-3.0.1/helio-3.0.x-master/src/TurbulenceModels$ ./Allwmake + wmake libso ../findroot/ wmakeLnInclude: linking include files to ./lnInclude Making dependency list for source file findRoot.C g++ -m64 -Dlinux64 -DWM_ARCH_OPTION=64 -DWM_DP -DWM_LABEL_SIZE=32 -Wall -Wextra -Wold-style-cast -Wnon-virtual-dtor -Wno-unused-parameter -Wno-invalid-offsetof -O3 -DNoRepository -ftemplate-depth-100 -I/opt/openfoam30/src/finiteVolume/lnInclude -I/opt/openfoam30/src/meshTools/lnInclude -IlnInclude -I. -I/opt/openfoam30/src/OpenFOAM/lnInclude -I/opt/openfoam30/src/OSspecific/POSIX/lnInclude -fPIC -c findRoot.C -o Make/linux64GccDPInt32Opt/findRoot.o g++ -m64 -Dlinux64 -DWM_ARCH_OPTION=64 -DWM_DP -DWM_LABEL_SIZE=32 -Wall -Wextra -Wold-style-cast -Wnon-virtual-dtor -Wno-unused-parameter -Wno-invalid-offsetof -O3 -DNoRepository -ftemplate-depth-100 -I/opt/openfoam30/src/finiteVolume/lnInclude -I/opt/openfoam30/src/meshTools/lnInclude -IlnInclude -I. -I/opt/openfoam30/src/OpenFOAM/lnInclude -I/opt/openfoam30/src/OSspecific/POSIX/lnInclude -fPIC -shared -Xlinker --add-needed -Xlinker --no-as-needed Make/linux64GccDPInt32Opt/findRoot.o -L/opt/openfoam30/platforms/linux64GccDPInt32Opt/lib \ -lfiniteVolume -o /home/gianmichele/OpenFOAM/gianmichele-3.0.1/platforms/linux64GccDPInt32Opt/lib/libfindroot.so '/home/gianmichele/OpenFOAM/gianmichele-3.0.1/platforms/linux64GccDPInt32Opt/lib/libfindroot.so' is up to date. + wmake libso incompressible Make/options:13:34: warning: backslash-newline at end of file [enabled by default] LIB_LIBS = -L$(FOAM_USER_LIBBIN) \ ^ wmakeLnInclude: linking include files to ./lnInclude Making dependency list for source file makeMyIncompressibleTurbulenceModel.C could not open file findRoot.H for source file makeMyIncompressibleTurbulenceModel.C due to No such file or directory g++ -m64 -Dlinux64 -DWM_ARCH_OPTION=64 -DWM_DP -DWM_LABEL_SIZE=32 -Wall -Wextra -Wold-style-cast -Wnon-virtual-dtor -Wno-unused-parameter -Wno-invalid-offsetof -O3 -DNoRepository -ftemplate-depth-100 -I../turbulenceModels/RAS/kEpsilonPANS -I../turbulenceModels/RAS/kOmegaSSTSASnew -I../turbulenceModels/RAS/kOmegaSSTPANS -I../turbulenceModels/RAS/kOmegaSSTgammaReTheta -I/opt/openfoam30/src/transportModels -I/opt/openfoam30/src/finiteVolume/lnInclude -I/opt/openfoam30/src/meshTools/lnInclude -I/opt/openfoam30/src/TurbulenceModels/turbulenceModels/lnInclude -I/opt/openfoam30/src/TurbulenceModels/incompressible/lnInclude -I/home/gianmichele/OpenFOAM/gianmichele-3.0.1/run/../src/findroot -IlnInclude -I. -I/opt/openfoam30/src/OpenFOAM/lnInclude -I/opt/openfoam30/src/OSspecific/POSIX/lnInclude -fPIC -c makeMyIncompressibleTurbulenceModel.C -o Make/linux64GccDPInt32Opt/makeMyIncompressibleTurbulenceModel.o In file included from makeMyIncompressibleTurbulenceModel.C:74:0: ../turbulenceModels/RAS/kOmegaSSTgammaReTheta/kOmegaSSTgammaReTheta.H:124:22: fatal error: findRoot.H: File o directory non esistente #include "findRoot.H" ^ compilation terminated. make: *** [Make/linux64GccDPInt32Opt/makeMyIncompressibleTurbulenceModel.o] Errore 1 gianmichele@gianmichele-K52Jc:~/OpenFOAM/gianmichele-3.0.1/helio-3.0.x-master/src/TurbulenceModels$ |
|
June 8, 2016, 11:02 |
|
#13 |
Senior Member
Join Date: Mar 2016
Posts: 133
Rep Power: 10 |
Ok i have been able to compiled incompressible turbulence models, adding missing files in lnInclude of incompressible's directory.
So now i can use komegaSSTRetheta but i can't give a value to Ret in inlet because by equation that you have suggested Ret = (1173.51 - 589.428Tu + 0.2196 / (Tu)^2) * F(lambatheta) when turbulence intensity Tu < 1.3 So i have to know function F(lambdatheta) but i don't know the value of lambdatheta...do you know how i can determine it? |
|
June 17, 2016, 15:51 |
new transition model
|
#14 |
Member
Alberto
Join Date: Sep 2013
Posts: 37
Rep Power: 12 |
After 8 years, there is a new version (or new model) of the k-kl-omega model.
There are a few problems with the k-kl-omega model in the farfield. One of them is the growth of Laminar Kinetic energy when separation occurs. Lopez and Walters have a paper (have not been published yet) correcting this issue: Maurin Lopez. D. K. Walters. “A recommended correction to the k-kl-omega transition sensitive eddy-viscosity model”. Journal of Fluid Engineering. This correction has to be made to the 2008 k-kl-omega model from now on. Now, Lopez and Walters also developed a new transitional model (k-omega-v2) as an alternative to the k-kl-omega one. This new model has more capabilities (it is more reliable) than the k-kl-omega model, especially in the farfield computations. Fortunately the paper for this new model is already publish. Maurin Lopez. D. K. Walters. “Prediction of transitional and fully turbulent free shear flows using an alternative to the laminar kinetic energy approach”. Journal of Turbulence, Vol 17, Iss. 3, 2016. If you see the papers, you will immediately see how the k-kl-omega model is not good for free shear flows, and how the new model corrects all those issues. From now on, k-kl-omega users have to start using the new k-omega-v2 model. malv83 is online now Add to malv83's Reputation Report Post Edit/Delete Message Reply With Quote Multi-Quote This Message Quick reply to this message |
|
June 17, 2016, 17:57 |
BCs
|
#15 |
New Member
Helio Villanueva
Join Date: Apr 2013
Location: Brazil
Posts: 14
Rep Power: 13 |
Hi giammy92!
By the log you posted and your directory structure (gianmichele@gianmichele-K52Jc:~/OpenFOAM/gianmichele-3.0.1/helio-3.0.x-master/src/TurbulenceModels$) the make files won't work properly. Your directory structure should be like this: Code:
gianmichele@gianmichele-K52Jc:~/OpenFOAM/gianmichele-3.0.1/src/TurbulenceModels$ Concerning the BCs, in prof. Hakan Nillson report you find in page 15 eq. 3.21 the way to calculate lambdaTheta. If you read the report on page 22 you will see how they used this equation Code:
The inlet boundary condition for Ret should be calculated by Eq.s 3.24-3.28 based on zero velocity gradient and free stream turbulent velocity which in this case becomes 171. |
|
November 6, 2016, 12:07 |
|
#16 |
Member
Jack
Join Date: May 2015
Posts: 98
Rep Power: 10 |
Hello,
I followed the steps above and running the Allwmake proceeded without any problems. However when running the flatplate test case I get the following error. This is despite the fact that the library libmyincompressibleturbulenceModels.so is found in /home/foamusr/OpenFOAM/foamusr-3.0.0/platforms/linux64GccDPInt32Opt/lib Code:
/*---------------------------------------------------------------------------*\ | ========= | | | \\ / F ield | OpenFOAM: The Open Source CFD Toolbox | | \\ / O peration | Version: 3.0.0 | | \\ / A nd | Web: www.OpenFOAM.org | | \\/ M anipulation | | \*---------------------------------------------------------------------------*/ Build : 3.0.0-6abec57f5449 Exec : simpleFoam Date : Nov 06 2016 Time : 17:04:29 Host : "loginusr" PID : 109472 Case : /home/foamusr/OpenFOAM/foamusr-3.0.0/run/flatplate nProcs : 1 sigFpe : Enabling floating point exception trapping (FOAM_SIGFPE). fileModificationChecking : Monitoring run-time modified files using timeStampMaster allowSystemOperations : Allowing user-supplied system call operations // * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * // Create time --> FOAM Warning : From function dlOpen(const fileName&, const bool) in file POSIX.C at line 1179 dlopen error : libmyincompressibleturbulenceModels.so: cannot open shared object file: No such file or directory --> FOAM Warning : From function dlLibraryTable::open(const fileName&, const bool) in file db/dynamicLibrary/dlLibraryTable/dlLibraryTable.C at line 99 could not load "libmyincompressibleturbulenceModels.so" Create mesh for time = 0 SIMPLE: convergence criteria field p tolerance 0.01 field U tolerance 0.001 field "(k|omega|Ret|intermittency)" tolerance 0.001 Reading field p Reading field U Reading/calculating face flux field phi Selecting incompressible transport model Newtonian Selecting turbulence model type RAS Selecting RAS turbulence model kOmegaSSTgammaReTheta --> FOAM FATAL ERROR: Unknown RASModel type kOmegaSSTgammaReTheta Valid RASModel types: 17 ( LRR LamBremhorstKE LaunderSharmaKE LienCubicKE LienLeschziner RNGkEpsilon SSG ShihQuadraticKE SpalartAllmaras kEpsilon kOmega kOmegaSST kOmegaSSTSAS kkLOmega qZeta realizableKE v2f ) From function RASModel::New(const volScalarField&, const volVectorField&, const surfaceScalarField&, transportModel&, const word&) in file ../turbulenceModels/lnInclude/RASModel.C at line 161. FOAM exiting |
|
November 21, 2016, 08:34 |
The same for 4.x
|
#17 |
New Member
Xavier Lamboley
Join Date: Jan 2015
Location: Bordeaux, France
Posts: 13
Rep Power: 11 |
Hello,
Thanks Helio Villanueva for your work, I just did the same for OpenFoam 4.x in this thread. It has changed again because kOmegaSST is now also a template, and the files to modify are now in TurbulenceModels/turbulenceModels/Base. |
|
February 2, 2017, 03:32 |
|
#18 |
Member
Gareth
Join Date: Jun 2010
Posts: 56
Rep Power: 15 |
Hi all
I have been going through the code for the 3.0 version and the original 2.0.x I am struggling with 1 line: In the git repository posted by HelioVillanueva, in src/TurbulenceModels/turbulenceModels/RAS/kOmegaSSTgammaReTheta/kOmegaSSTgammaReTheta.C on line 591: Code:
volScalarField Ptheta = 0.03*pow(mag(U),2.0)/(500.0*nu*(1.0-Ftheta,1.0)); Code:
0.03*pow(mag(U),2.0)/(500.0*nu*1.0); Also as an edit -> should the division not be just by 500*nu()? The 1.0-Ftheta should not be included in the division. I hope someone can help me with this. Regards |
|
Thread Tools | Search this Thread |
Display Modes | |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Superlinear speedup in OpenFOAM 13 | msrinath80 | OpenFOAM Running, Solving & CFD | 18 | March 3, 2015 05:36 |
SST transition model | mb.pejvak | Main CFD Forum | 0 | August 27, 2012 02:41 |
Viscosity ratio in gamma-theta transition model based on k-w sst turb model | Qiaol618 | Main CFD Forum | 8 | June 9, 2012 06:43 |
where to set CFX Transition Model? | steven | CFX | 6 | January 17, 2007 11:19 |
model transition | nico | FLUENT | 0 | February 8, 2004 09:04 |