CFD Online Discussion Forums - Problem while compiling a turbulence model in OF 4.1

CFD Online Discussion Forums (https://www.cfd-online.com/Forums/)

- OpenFOAM Programming & Development (https://www.cfd-online.com/Forums/openfoam-programming-development/)

- - Problem while compiling a turbulence model in OF 4.1 (https://www.cfd-online.com/Forums/openfoam-programming-development/201814-problem-while-compiling-turbulence-model-4-1-a.html)

Problem while compiling a turbulence model in OF 4.1

Hi everybody,

I am having some problems compiling a modified k-epsilon turbulence model in OpenFoam 4.1

To be sure I'm not writing anything wrong in the files, I have copied the original files of the model and I have changed all of the "kEpsilon" terms for "mykEpsilon" and nothing else.

My Make/files has the following:

Quote:

mykEpsilon.C

LIB = $(FOAM_USER_LIBBIN)/libmyIncompressibleRASModels

and my Make/options is:

Quote:

EXE_INC = \
-I$(LIB_SRC)/finiteVolume/lnInclude \
-I$(LIB_SRC)/meshTools/lnInclude \
-I$(LIB_SRC)/TurbulenceModels/turbulenceModels/lnInclude

LIB_LIBS = \
-lfiniteVolume \
-lmeshTools

Despite of that, the error when I try to compile is this:

Quote:

g++ -std=c++0x -m64 -Dlinux64 -DWM_ARCH_OPTION=64 -DWM_DP -DWM_LABEL_SIZE=32 -Wall -Wextra -Wold-style-cast -Wnon-virtual-dtor -Wno-unused-parameter -Wno-invalid-offsetof -O3 -DNoRepository -ftemplate-depth-100 -I/opt/openfoam4/src/finiteVolume/lnInclude -I/opt/openfoam4/src/meshTools/lnInclude -I/opt/openfoam4/src/TurbulenceModels/turbulenceModels/lnInclude -IlnInclude -I. -I/opt/openfoam4/src/OpenFOAM/lnInclude -I/opt/openfoam4/src/OSspecific/POSIX/lnInclude -fPIC -c mykEpsilon.C -o Make/linux64GccDPInt32Opt/mykEpsilon.o
mykEpsilon.C:40:6: error: redefinition of \u2018void Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :correctNut()\u2019
void mykEpsilon<BasicTurbulenceModel>::correctNut()
^
In file included from mykEpsilon.H:213:0,
from mykEpsilon.C:26:
mykEpsilon.C:40:6: error: \u2018virtual void Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :correctNut()\u2019 previously declared here
void mykEpsilon<BasicTurbulenceModel>::correctNut()
^
mykEpsilon.C:51:21: error: redefinition of \u2018Foam::tmp<Foam::fvMatrix<double> > Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :kSource() const\u2019
tmp<fvScalarMatrix> mykEpsilon<BasicTurbulenceModel>::kSource() const
^
In file included from mykEpsilon.H:213:0,
from mykEpsilon.C:26:
mykEpsilon.C:51:21: error: \u2018virtual Foam::tmp<Foam::fvMatrix<double> > Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :kSource() const\u2019 previously declared here
tmp<fvScalarMatrix> mykEpsilon<BasicTurbulenceModel>::kSource() const
^
mykEpsilon.C:66:21: error: redefinition of \u2018Foam::tmp<Foam::fvMatrix<double> > Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :epsilonSource() const\u2019
tmp<fvScalarMatrix> mykEpsilon<BasicTurbulenceModel>::epsilonSource() const
^
In file included from mykEpsilon.H:213:0,
from mykEpsilon.C:26:
mykEpsilon.C:66:21: error: \u2018virtual Foam::tmp<Foam::fvMatrix<double> > Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :epsilonSource() const\u2019 previously declared here
tmp<fvScalarMatrix> mykEpsilon<BasicTurbulenceModel>::epsilonSource() const
^
mykEpsilon.C:83:1: error: redefinition of \u2018Foam::RASModels::mykEpsilon<BasicTurbulenceM odel>::mykEpsilon(const alphaField&, const rhoField&, const volVectorField&, const surfaceScalarField&, const surfaceScalarField&, const transportModel&, const Foam::word&, const Foam::word&)\u2019
mykEpsilon<BasicTurbulenceModel>::mykEpsilon
^
In file included from mykEpsilon.H:213:0,
from mykEpsilon.C:26:
mykEpsilon.C:83:1: error: \u2018Foam::RASModels::mykEpsilon<BasicTurbulenceM odel>::mykEpsilon(const alphaField&, const rhoField&, const volVectorField&, const surfaceScalarField&, const surfaceScalarField&, const transportModel&, const Foam::word&, const Foam::word&)\u2019 previously declared here
mykEpsilon<BasicTurbulenceModel>::mykEpsilon
^
mykEpsilon.C:200:6: error: redefinition of \u2018bool Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :read()\u2019
bool mykEpsilon<BasicTurbulenceModel>::read()
^
In file included from mykEpsilon.H:213:0,
from mykEpsilon.C:26:
mykEpsilon.C:200:6: error: \u2018virtual bool Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :read()\u2019 previously declared here
bool mykEpsilon<BasicTurbulenceModel>::read()
^
mykEpsilon.C:221:6: error: redefinition of \u2018void Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :correct()\u2019
void mykEpsilon<BasicTurbulenceModel>::correct()
^
In file included from mykEpsilon.H:213:0,
from mykEpsilon.C:26:
mykEpsilon.C:221:6: error: \u2018virtual void Foam::RASModels::mykEpsilon<BasicTurbulenceModel>: :correct()\u2019 previously declared here
void mykEpsilon<BasicTurbulenceModel>::correct()
^
make: *** [Make/linux64GccDPInt32Opt/mykEpsilon.o] Error 1

Since I have not redefined anything, I don't know why is this happening. Could anybody help me with this?
Thank you very much!!
Alex

I've been able to compile my own turbulence models by creating the necessary .H and .C files. Then using an (eg) makeTurbulenceModel.C to create the new library. I've included example code for a new les model in 4.x -- it will hopefully work for you in 4.1. I've found that I get warnings at run time about various duplicates, but the new model works (once the new library is included in the control dict). I believe I originally pulled code to do this from here : http://hassankassem.me/posts/newturbulencemodel/.

Code:

/*---------------------------------------------------------------------------*\

  =========                 |

  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox

   \\    /   O peration     |

    \\  /    A nd           | Copyright (C) 2013-2016 OpenFOAM Foundation

     \\/     M anipulation  |

-------------------------------------------------------------------------------

License

    This file is part of OpenFOAM.

    OpenFOAM is free software: you can redistribute it and/or modify it

    under the terms of the GNU General Public License as published by

    the Free Software Foundation, either version 3 of the License, or

    (at your option) any later version.

    OpenFOAM is distributed in the hope that it will be useful, but WITHOUT

    ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or

    FITNESS FOR A PARTICULAR PURPOSE.  See the GNU General Public License

    for more details.

    You should have received a copy of the GNU General Public License

    along with OpenFOAM.  If not, see <http://www.gnu.org/licenses/>.

\*---------------------------------------------------------------------------*/



#include "CompressibleTurbulenceModel.H"

#include "compressibleTransportModel.H"

#include "fluidThermo.H"

#include "addToRunTimeSelectionTable.H"

#include "makeTurbulenceModel.H"



#include "ThermalDiffusivity.H"

#include "EddyDiffusivity.H"



#include "laminar.H"

#include "RASModel.H"

#include "LESModel.H"



// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //



makeBaseTurbulenceModel

(

    geometricOneField,

    volScalarField,

    compressibleTurbulenceModel,

    CompressibleTurbulenceModel,

    ThermalDiffusivity,

    fluidThermo

);



#define makeLESModel(Type)                                                     \

    makeTemplatedTurbulenceModel                                               \

    (fluidThermoCompressibleTurbulenceModel, LES, Type)



// -------------------------------------------------------------------------- //

// LES models

// -------------------------------------------------------------------------- //



#include "customModel.H"

makeLESModel(customModel);



// ************************************************************************* //

Thank you very much!!!

When I first read that post you referenced I didn't understand it, but now thanks to you and reading it calmly, I could be able to compile my model.

I had to do some minor changes, though, because I haven't copied the entire turbulence library, so I had to change some of the directions of the includes, but the important thing is that it works :)

Thanks again :)