CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > OpenFOAM > OpenFOAM Running, Solving & CFD

phase diameter and phase compressibility in multiphaseEulerFoam solver

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree4Likes
  • 2 Post By mike.franky
  • 2 Post By kwardle

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   March 9, 2016, 06:06
Default phase diameter and phase compressibility in multiphaseEulerFoam solver
  #1
Member
 
Michael Frank
Join Date: Aug 2012
Posts: 55
Rep Power: 11
mike.franky is on a distinguished road
Hello,

I have recently started using OpenFOAM. Specifically, I am trying to model a multiphase/multicomponent bubble column-like problem. It seems to me that the multiphaseEulerFoam solver is perfectly suitable for this task. However, I have a couple of questions.

First, for the calculation of the interphase interactions, the Eulerian model assumes that each phase forms bubbles of a constant diameter. In the absence of any experimental data, is there any empirical model that we can use to calculate this diameter?

My second question regards the compressibility of each phase. The documentation states that the solver is for compressible fluid phases (http://cfd.direct/openfoam/user-guide/standard-solvers/). Glancing at the code however, I can see that the energy (or temperature) equation is not solved. Am I missing something?

Finally, commercial software packages often consider a multiphase model called the mixture model (or at least that is what ANSYS is calling it). This is much more efficient than its Eulerian counterpart and might be suitable for my case. Does OpenFOAM have something equivalent?

Thanks in advance for any help

Mike
Luttappy and Aabadani like this.
mike.franky is offline   Reply With Quote

Old   March 9, 2016, 16:02
Default
  #2
Senior Member
 
Kent Wardle
Join Date: Mar 2009
Location: Illinois, USA
Posts: 219
Rep Power: 19
kwardle is on a distinguished road
Mike,
1. You are correct that the solver as released can handle a constant diameter only. There is a diameterModel class to add in other models and there is one that can handle size changes of bubbles due to external pressure changes. There are numerous equations in literature for estimating bubble size from properties and flow conditions. Not sure on accuracy. Probably more reliable is taking a case which the bubble size is 'known' to start.

2. multiphaseEulerFoam does not include compressibility. Depending on the version of OF you are using, twoPhaseEulerFoam might.

3. One of the main features of multiphaseEulerFoam is to enable euler-euler multiphase (momentum equation per phase with inter-phase drag) along with a VOF-style sharpened interface where this is needed. Fluent's 'mixture model' is a single shared momentum equation with a slip velocity to account for drag between phases. This is only appropriate for certain kinds of problems as the Fluent manual can tell you.

Hope that helps.
-Kent
Luttappy and Aabadani like this.
kwardle is offline   Reply With Quote

Old   March 14, 2016, 05:13
Default
  #3
Member
 
Michael Frank
Join Date: Aug 2012
Posts: 55
Rep Power: 11
mike.franky is on a distinguished road
Hi Kent,

Thanks for your reply. It is indeed very useful.

Regarding the diameter model, I see that I can use the isothermalDiameter model. To use this do I simply specify it in the transportProperties dictionary? Looking at the code I understand that there is no need for programming and recompiling the solver.

As for the compressibility, is it possible to adjust the code to be compressible (i.e. following a similar approach to the twoPhaseEuler solver) or is this a much more complicated task?

Thanks again for your help
Mike
mike.franky is offline   Reply With Quote

Old   March 14, 2016, 09:03
Default
  #4
Senior Member
 
Kent Wardle
Join Date: Mar 2009
Location: Illinois, USA
Posts: 219
Rep Power: 19
kwardle is on a distinguished road
Addition of compressibility would be much more involved as it requires insertion of density as a variable and rearranging how the PDE is written and solved. You can take a look at an earlier version of twoPhaseEulerFoam and compare with recent to get an idea.
It is reasonably straightforward to implement a Boussinesq approximation density variation into multiphaseEulerFoam to account for natural convection flows where density variation throughout the system is not small but the difference is critical to the physics.
kwardle is offline   Reply With Quote

Old   March 15, 2016, 18:18
Default
  #5
Senior Member
 
Join Date: Jan 2013
Posts: 372
Rep Power: 12
openfoammaofnepo is on a distinguished road
My understanding for the compressibility included in multiphaseEulerFoam is because they include "p = p_rgh + rho*gh;". the hydrodynamics and the thermodynamics are not decoupled. So the compression would also lead to the change of the density. However, since the temperature is solved in that solver, so the change of T would not.
openfoammaofnepo is offline   Reply With Quote

Old   March 16, 2016, 03:27
Default
  #6
Member
 
Juho Peltola
Join Date: Mar 2009
Location: Finland
Posts: 89
Rep Power: 15
juho is on a distinguished road
You may also want to check out the new reactingTwo/MultiphaseEulerFoam solvers:

https://github.com/OpenFOAM/OpenFOAM...ctingEulerFoam
juho is offline   Reply With Quote

Old   March 16, 2016, 18:47
Default
  #7
Member
 
Michael Frank
Join Date: Aug 2012
Posts: 55
Rep Power: 11
mike.franky is on a distinguished road
Thank you all for your help.

openfoammaofnepo, so the multiphaseEulerFoam solver is in fact compressible? Thinking about it, the isothermal diameter model must also include compressibility effects since the bubbles expand and contract with pressure.

Juho the solver you suggested looks very interesting. Does it have any documentation?
mike.franky is offline   Reply With Quote

Old   May 20, 2020, 09:45
Default
  #8
Senior Member
 
Ehsan Asgari
Join Date: Apr 2010
Posts: 471
Rep Power: 16
syavash is on a distinguished road
Quote:
Originally Posted by kwardle View Post
Mike,
1. You are correct that the solver as released can handle a constant diameter only. There is a diameterModel class to add in other models and there is one that can handle size changes of bubbles due to external pressure changes. There are numerous equations in literature for estimating bubble size from properties and flow conditions. Not sure on accuracy. Probably more reliable is taking a case which the bubble size is 'known' to start.

2. multiphaseEulerFoam does not include compressibility. Depending on the version of OF you are using, twoPhaseEulerFoam might.

3. One of the main features of multiphaseEulerFoam is to enable euler-euler multiphase (momentum equation per phase with inter-phase drag) along with a VOF-style sharpened interface where this is needed. Fluent's 'mixture model' is a single shared momentum equation with a slip velocity to account for drag between phases. This is only appropriate for certain kinds of problems as the Fluent manual can tell you.

Hope that helps.
-Kent
Dear Kent,

I was wondering if the multiphaseEulerFoam is suitable for an application that I study:

The problem consists of air-water-solid phases, such that the solid particle are substantially larger than the cell size. This has led me to believe that the Euler-Lagrange method, as implemented in DPMFoam cannot be considered for my problem.
On the other hand, I think the VOF is essential to capture the air-solid, air-water, and water-solid interfaces. In short, the solid particles are to be carried by a mixture of air-water, with the gravity force active.
Now, the question is can I utilize multiphaseEulerFoam for this problem, or should I consider another approach??

I'd really appreciate your help on this matter.

Kind regards,
syavash
syavash is offline   Reply With Quote

Reply

Tags
compressible flow, multiphase, multiphaseeulerfoam, phase diameter

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[multiphase] C_UDMI in DEFINE_PROPERTY for diameter of secondary phase SJSW Fluent UDF and Scheme Programming 1 December 12, 2015 12:06
Eulerian phase gas diameter hwet Fluent Multiphase 3 August 14, 2015 05:59
phase names in multiphaseEulerFoam: strange behaviour kobelak OpenFOAM Running, Solving & CFD 0 May 11, 2015 18:35
Derive fixed number of phase from clone () in multiphaseEulerFoam Solver Aj Nair OpenFOAM Programming & Development 0 December 16, 2013 20:41
compressible two phase flow in CFX4.4 youngan CFX 0 July 1, 2003 23:32


All times are GMT -4. The time now is 03:38.