CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > OpenFOAM > OpenFOAM Running, Solving & CFD

inletOutlet and outletInlet boundary condition

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   April 4, 2018, 11:26
Default inletOutlet and outletInlet boundary condition
  #1
Member
 
Sheikh Ahmed
Join Date: Dec 2015
Location: South Carolina, USA
Posts: 88
Rep Power: 8
sahmed is on a distinguished road
Dear Foamers
I am trying to get your attention to this age-old problem of inletOutlet boundary conditions. I hope many of you have successfully used this boundary condition. Now PLEASE help me.
I have a backflow situation at the outlet where the backflow velocity is unknown. Now, for the inlet velocity and pressure I am using-

inlet_velocity
{
type fixedValue;;
value uniform (0.13 0 0);
}

inlet_pressure
{
type zeroGradient;
}

Now, in order to take care of the backflow at the outlet, I am using-

outlet_velocity
{
type inletOutlet;
inletValue uniform (0 0 0);
value uniform (0 0 0);
}

outlet_pressure
{
type outletInlet;
outletValue 101325;
value 101325;
}

What I understood is that, during back flow, the backflow velocity will be calculated based on the pressure difference. I used the backflow pressure as atmospheric. Also, I am using the inletOutlet for the outlet temperature as well where the backflow temperature is 300K.
PLEASE let me know if this is correct or not. If not, please correct me.
Thanks in advance.
sahmed is offline   Reply With Quote

Old   April 4, 2018, 22:57
Default
  #2
Senior Member
 
Taher Chegini
Join Date: Nov 2014
Location: Houston, Texas
Posts: 125
Rep Power: 10
Taataa is on a distinguished road
Regarding the inlet, If you have gravity and surface tension in your problem you should use fixedFluxPressure for pressure instead of zeroGradient.

Regarding the outlet, usually pressure is specified explicitly through a boundary condition such as totalPressure and for velocity pressureInletOutletVelocity is imposed.
Taataa is offline   Reply With Quote

Old   April 4, 2018, 23:19
Default
  #3
Member
 
Sheikh Ahmed
Join Date: Dec 2015
Location: South Carolina, USA
Posts: 88
Rep Power: 8
sahmed is on a distinguished road
Quote:
Originally Posted by Taataa View Post
Regarding the inlet, If you have gravity and surface tension in your problem you should use fixedFluxPressure for pressure instead of zeroGradient.

Regarding the outlet, usually pressure is specified explicitly through a boundary condition such as totalPressure and for velocity pressureInletOutletVelocity is imposed.
Thank you very much Taher for your reply. I am not considering gravity and surface tension in the inlet, that means zeroGradient pressure is ok right?
For the outlet pressure, I could understand the pressureInletOutletVelocity boundary for the outlet velocity, but for pressure, I saw the totalPressure bc mostly for inlets. That is why I was confused.
Could you PLEASE tell me what should be the field entries (rho, p0, value) in this case? I am expecting backflow air coming inside the domain from atmospheric condition. So should I use the following for subsonic compressible condition-
{
type totalPressure;
p0 uniform 101325;
value uniform 101325;
}

I WOULD HIGHLY APPRECIATE YOUR SUGGESTION.
Thanks
sahmed is offline   Reply With Quote

Old   April 4, 2018, 23:39
Default
  #4
Senior Member
 
Taher Chegini
Join Date: Nov 2014
Location: Houston, Texas
Posts: 125
Rep Power: 10
Taataa is on a distinguished road
You can find good and reliable explanation here. EDIT (Sections 5.2.3.1 and 5.2.3.2)

Yes, only p0 is mandatory. So it should work well.

I meant gravity and surface tension in your whole domain not just the boundary. If gravity and/or surface tension play a role in your simulation you should use that BC.
Taataa is offline   Reply With Quote

Old   April 5, 2018, 00:55
Default
  #5
Member
 
Sheikh Ahmed
Join Date: Dec 2015
Location: South Carolina, USA
Posts: 88
Rep Power: 8
sahmed is on a distinguished road
Quote:
Originally Posted by Taataa View Post
You can find good and reliable explanation here. EDIT (Sections 5.2.3.1 and 5.2.3.2)

Yes, only p0 is mandatory. So it should work well.

I meant gravity and surface tension in your whole domain not just the boundary. If gravity and/or surface tension play a role in your simulation you should use that BC.
Thanks once again for the link. it clearly explains what I need.
Just one quick question- in the damBreak tutorial of the link where totalPressure boundary is used for the outlet pressure, the P0 value is specified as 0 which I didnt understand. If the backflow is coming from atmosphere, shouldnt it be 101325 instead of 0?
Thanks in advance.
sahmed is offline   Reply With Quote

Old   April 5, 2018, 11:44
Default
  #6
Senior Member
 
Taher Chegini
Join Date: Nov 2014
Location: Houston, Texas
Posts: 125
Rep Power: 10
Taataa is on a distinguished road
Quote:
Originally Posted by sahmed View Post
Thanks once again for the link. it clearly explains what I need.
Just one quick question- in the damBreak tutorial of the link where totalPressure boundary is used for the outlet pressure, the P0 value is specified as 0 which I didnt understand. If the backflow is coming from atmosphere, shouldnt it be 101325 instead of 0?
Thanks in advance.
If the solver is incompressible gauge pressure matters not absolute pressure so that's why atmospheric pressure is set to zero whereas in compressible solvers absolute pressure should be used hence the value of 101325 for atmospheric pressure.
Taataa is offline   Reply With Quote

Old   April 5, 2018, 11:54
Default
  #7
Member
 
Sheikh Ahmed
Join Date: Dec 2015
Location: South Carolina, USA
Posts: 88
Rep Power: 8
sahmed is on a distinguished road
Got it. Thanks a lot Taher.
sahmed is offline   Reply With Quote

Old   April 5, 2018, 11:54
Default
  #8
Senior Member
 
Taher Chegini
Join Date: Nov 2014
Location: Houston, Texas
Posts: 125
Rep Power: 10
Taataa is on a distinguished road
You're welcome.
Taataa is offline   Reply With Quote

Old   April 13, 2018, 10:18
Default
  #9
Member
 
Sheikh Ahmed
Join Date: Dec 2015
Location: South Carolina, USA
Posts: 88
Rep Power: 8
sahmed is on a distinguished road
Hi Taher
Can I have your email address so that I can share something related to my simulation with you with some attachment?
Thanks in advance.

~SFA
sahmed is offline   Reply With Quote

Reply

Tags
backflow, inletoutlet, outletinlet

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Questions about the inletOutlet and outletInlet boundary conditions brooksmoses OpenFOAM Running, Solving & CFD 24 March 2, 2021 01:16
mixed inflow/outflow downstream boundary condition question peob OpenFOAM Running, Solving & CFD 3 February 3, 2017 10:54
confusion about inletOutlet & outletInlet BC Mike_star OpenFOAM Running, Solving & CFD 3 June 9, 2016 09:57
boundary condition options bendel_boy OpenFOAM Running, Solving & CFD 0 January 7, 2015 05:20
Understanding code of inletOutlet / outletInlet fredo490 OpenFOAM Programming & Development 10 June 13, 2013 12:45


All times are GMT -4. The time now is 18:39.