Hi,
I want to calculate the
Hi,
I want to calculate the airflow in a room with heated walls and a ventilation in and outlet. Do you have any hint, which solver I should use? I found 'turbfoam' for incompressible, turbulent flow, but it does not seem that it supports buoyancy. The other solver I found is 'buoyantFoam'. This one is for compressible flow and does not seem to be suitable either... Can you make a suggestion? Greetings! Fabian 
'buoyantFoam' is suitable, in
'buoyantFoam' is suitable, in fact it was developed for exactly this kind of flow. Why do you think it is unsuitable? There is also 'buoyantSimpleFoam' for steadystate buoyancydriven flows.

Hi,
because it is for compres
Hi,
because it is for compressible flow!? And usually we use a incompressible solver. Fabian 
... but buoyancydriven flows
... but buoyancydriven flows are compressible; the density changes as a function of temperature and pressure!

...but the Manumber is smalle
...but the Manumber is smaller than 0.3, so you should be able to use incompressible.
Actually I would be the first at our building technology institute who is using a compressible one. Doesn't it take longer to get convergence with a compressible solver? Greetings! Fabian 
You could make the assumption
You could make the assumption of incompressibility if it is appropriate for your problem but remember compressibility is not just about the Manumber, the density could significantly vary due to pressure changes as a consequence of bodyforces e.g. gravity in the atmosphere and I didn't want to limit the kind of buoyancydiven flows than buoyantFoam could be applied to.
If the assumption of incompressibility is important to you it would not be difficult to remove the compressibility effects from buoyantFoam but I doubt it will make much difference to the performance of the code because it already uses a lowManumber pressure solver and the compressibility effects make that slightly diagonally dominant which is beneficial to convergence. The only downside of maintaining compressibility effects is the possibility of the solution supporting waves which would not be present in a incompressible solution and which you may not be interested in. 
I think it is good that there
I think it is good that there is no limit, but in a room it is possible to neglect the change of density due to pressure differences.
I will try the buoyantFoam, but maybe you can give me a hint, how to remove the compressibility effects. My Prof. wants to have incompressible. Greetings! Fabian 
I am not sure what approximati
I am not sure what approximations your Prof would like you to introduce but you have the source code for buoyantFoam and are free to change it in anyway he feels is appropriate.
Could you please explain why your Prof wants incompressible given that compressible is already implemenented and more realistic? What do you gain from the assumption of incompressibility? 
Hi,
he mentioned, that it w
Hi,
he mentioned, that it won't converge as fast ... but I will try out compressible with the low Manumber pressure solver; I actually did not tell him about that. Changing it to incompressible, is it enought to take care about the files in : OpenFOAM1.1/applications/solvers/heatTransfer/buoyantFoam Greetings! Fabian 
> he mentioned, that it won't
> he mentioned, that it won't converge as fast ...
How does he know? You said that all the codes you have are incompressible or is there one in which he could have tried both compressible and incompressible? As I have said before running compressible will actually improve the convergence of the pressure solver but may affect the overall convergence by supporting pressure waves but give that your flow is lowMa and in a small domain I doubt there will be much difference. > Changing it to incompressible, is it enought to take care about the files in : OpenFOAM1.1/applications/solvers/heatTransfer/buoyantFoam Yes. 
Sorry, I forgot to mention, th
Sorry, I forgot to mention, that we use fluent and cfx.
As soon, as I get my fluent mesh into OpenFoam, I try out compressible and when I got the incompressible variant (if I can get done), I will compare both and let you know. Now, I'am actually curious about the differences. Greetings! Fabian 
FOAM has been compared with CF
FOAM has been compared with CFX for buoyancydriven flows a few years ago and as far as I am aware the solution algorithms are very similar and CFX also includes the effect of pressure in density as in buoyantFoam. Either way the solutions were VERY similar.
Are you sure you are running CFX totally incompressible for your problems? What assumptions are being made for this? Is the density included in the transport equations but only adjusted as a function of temperature or is it assumed constant except for the buoyancy force? 
Boussinesq approximation is us
Boussinesq approximation is used.

I would like to simulate buoya
I would like to simulate buoyancy driven convection in a Heavy Fuel Oil tank. Is buoyantFoam suitable for this kind of problems (Oil is incompressible, but viscosity and density change with temperature)?
How can I define the characteristics of Heavy Fuel Oil (density, specific heat, thermal conductivity, viscosity..)? 
You will need to write your ow
You will need to write your own, probably using Bousinesq assumption. buoyantFoam solvers are all for compressible gasses really and you will want a compressible liquid.
Hrv 
but at low mach cases wouldn't
but at low mach cases wouldn't compressible gases in buoyantFoam have the same behavior?

If I use buoyantFoam to simula
If I use buoyantFoam to simulate heating of a water mass which modifications would I do and where?
thanks! 
Hi
i would want to use buoy
Hi
i would want to use buoyantsimplefoam but for incompressible fluids which modifications i have to do and where? best regards 
I am developing a Simple based
I am developing a Simple based code suitable to study flames propagating in atmosphere. To do that I need to consider the effect of gravity, so I was looking to either "buoyantFoam" or "buoyantSimpleFoam" whose UEqns have something not straightforward to me. Indeed developing the RHS of the momentum equation one gets grad(p)rho*(grad(gh)), while
it should be grad(p)grad(gh*rho), does the lack of gh*grad(rho) rely on some semplications I am missing? 
Dear all!
I am about to loo
Dear all!
I am about to look on fires in tunnels (low MachNumber, buoyant driven flow, radiation; LES) with the help of CFD and searched the web and this forum about information concerning solving this kind of flow in OF. I have the impression that Xoodles could be the most appropriate solver for that. Is this correct? Does this solver also handles the effects of smoke on radiation phenomena? Thanx for any comment! Mabinty 
All times are GMT 4. The time now is 08:34. 