I've tried to run some 3D simu
I've tried to run some 3D simulations with a Reynolds stress model lately, but they will not converge. I've played around with the settings and variables but the simulations remains unstable. However, with the k-epsilon model the simulations converges nicely. Have anyone else had succees with the RSM, or am I doing something utterly wrong?
|
It should work without problem
It should work without problems. If you are running something relatively small and simple I wouldn't mind having a look, just to make sure RSTM is still fine.
Hrv |
It's a small case where two sq
It's a small case where two square ducts, each of them with dimensions 0.1*0.1*1 (m), are joined together in a 90 degree bend. Air is flowing through at a Reynolds number of 100,000. The turbulence intensity, and the turbulent length scales compared to the outer dimensions, are both assumed to be 10 %.
The kEpsilon and RNGkEpsilon works well on this geometry, but I cannot obtain a solution with the LRR or LaunderGibsonRSTM models. |
|
Steve,
I don't think you ma
Steve,
I don't think you managed to attach the file. Hrv |
Hi,
Im a beginner att openF
Hi,
Im a beginner att openFOAM but I have tried the turbmodels you mension and I have had a similar problem which i got thru by having a epsilon value 3 times as big as when I used the kepsilon models. /erik |
I'll try again:-)
Here is a
|
I don't see a problem: it conv
I don't see a problem: it converges monotonically. This is what I did:
- run 100 iterations with k-epsilon - calculated Reynolds stress using R - restarted with Launder-Reece-Rodi RSTM. Converges smoothly with no trouble. I can either give in normal stress only at the inlet of the full equilibrium R from the k-epsilon model. A few comments: - your numerics is rubbish: you should try using second order - if you try to start up LRR from the beginning it blows up because of epsilon. You should really start k-epsilon and restart; otherwise you will have fun trying to set up under-relaxation coefficients - at the end of the residual graph you start hitting solver convergence tolerances: hence the plateau - I can make this even better using my fixedMeanValue outlet b.c.: makes it prettier close to the outlet http://www.cfd-online.com/OpenFOAM_D...ges/1/3006.jpg Hrv |
Hi Hrvoje
I didn't now abou
Hi Hrvoje
I didn't now about the "R" function. When I followed you steps the solution converged without problem. Thank you Steve |
1 Attachment(s)
Hi
I try to use LRR for my simulation. I'm simulating an atmospheric boundary layer, but my result with it are completely different from the same case with k-eps model. Post my case. Thanks |
Quote:
Could you please provide an fvSchemes and fvSolution that aren't "rubbish"? I'm not very well-versed in numerical methods (yet!) and would like to get a better idea of what 'good' settings for LRR are. Thanks! |
All times are GMT -4. The time now is 15:51. |