try blockCoupledScalarTransportFoam
What about the blockCoupledScalarTransportFoam? I know that is on the same mesh, with two equations coupled to eachother through a source term
Code:
fvScalarMatrix TEqn Dan 
Hi,
there is a coupled solver under development in extend, as pointed out in comment 2 (warning: it is a bit complicated at a first glance). However, you could define j as a volTensorField, and initialise it with your value of j. Code:
volTensorField j dimensionSet(.....) if the tensor has dimensional units. Keep in mind however that the solution won't be coupled but sequential: meaning component by component. Best, 
blockCoupledScalarTransportFoam  coupling via operator
Hi!
I am trying to implement a solver for the following two coupled equations: Equation 1: laplacian(D1, phi_real)  laplacian(D2, phi_img) = 0 Equation 2: laplacian(D1, phi_img) + laplacian(D2, phi_real) = 0 First, I implemented a segregated version: solve( fvm::laplacian(D1, phi_real)  fvc::laplacian(D2, phi_img)); solve( fvm::laplacian(D1, phi_img) + fvc::laplacian(D2, phi_real)); which seems to work for weakly couplings. Naturally, this approach is rather useless if the coupling grows stronger. Hence, I had a look at 1.6.ext's solver "blockCoupledScalarTransportFoam". I guess I understand the main idea of it. I think one of the critical parts is the manipulation of the offdiagonal elements and the block source in order to create the correctly coupled system which looks like that in blockCoupledScalarTransportFoam.C: forAll(d, i) { d[i](0,1) = alpha.value()*mesh.V()[i]; d[i](1,0) = alpha.value()*mesh.V()[i]; blockB[i][0] = alpha.value()*blockX[i][1]*mesh.V()[i]; blockB[i][1] = alpha.value()*blockX[i][0]*mesh.V()[i]; } The above approach is rather simple for a coupling of the equations via the scalar "alpha". However, can something similar also be done if the coupling is done via an operator such as laplacian()? I tried to figure that out, but I am stuck. Any helpful comments would be very appreciated. Cheers, Christian 
hi,
is there anybody still following this topic? i'm having exactly the same interests as christian has pointed out. The blockCoupledScalarTransportFoam is very understandable for the idea of block matrix construction. However, when it comes to the coupling of transport terms (like grad(p) in the momentum equation, not as simple as the source term coupling in the blockCoupledScalarTransportFoam case), it is hard to construct the block because no implict gradient scheme is available :( does anyone have idea about a fvm::grad() scheme? 
Hi Tian,
Quote:
grad * (sigma * grad(phi_real))  grad * ((E0*Er*w) * grad(phi_imag)) = 0 grad * (sigma * grad(phi_imag)) + grad * ((E0*Er*w) * grad(phi_real)) = 0 using the following code: #include "fvCFD.H" #include "fieldTypes.H" #include "Time.H" #include "fvMesh.H" #include "blockLduSolvers.H" #include "VectorNFieldTypes.H" #include "volVectorNFields.H" #include "blockVectorNMatrices.H" #include "blockMatrixTools.H" // * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * // int main(int argc, char *argv[]) { # include "setRootCase.H" # include "createTime.H" # include "createMesh.H" # include "createFields.H" // * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * // // # include "CourantNo.H" for (runTime++; !runTime.end(); runTime++) { Info<< "Time = " << runTime.timeName() << nl << endl; # include "readSIMPLEControls.H" for (int nonOrth=0; nonOrth<=nNonOrthCorr; nonOrth++) { fvScalarMatrix phi_realEqn (  fvm::laplacian(EpsilonTimesAngVel, phi_real) ); phi_realEqn.relax(); fvScalarMatrix phi_realEqn2 (  fvm::laplacian(Sigma, phi_real) ); phi_realEqn2.relax(); fvScalarMatrix phi_imgEqn (  fvm::laplacian(EpsilonTimesAngVel, phi_img) ); phi_imgEqn.relax(); fvScalarMatrix phi_imgEqn2 (  fvm::laplacian(Sigma, phi_img) ); phi_imgEqn2.relax(); // Prepare block system BlockLduMatrix<vector2> blockM(mesh); BlockLduMatrix<vector2> blockM2(mesh); // Grab block diagonal and set it to zero Field<tensor2>& d = blockM.diag().asSquare(); d = tensor2::zero; Field<tensor2>& d2 = blockM2.diag().asSquare(); d2 = tensor2::zero; // Grab linear offdiagonal and set it to zero Field<tensor2>& u = blockM.upper().asSquare(); Field<tensor2>& l = blockM.lower().asSquare(); u = tensor2::zero; l = tensor2::zero; Field<tensor2>& u2 = blockM2.upper().asSquare(); Field<tensor2>& l2 = blockM2.lower().asSquare(); u2 = tensor2::zero; l2 = tensor2::zero; // forAll(u, j) // { // u[j](0,0) = 0.0; // u[j](1,0) = 0.0; // u[j](0,1) = 0.0; // u[j](1,1) = 0.0; // u2[j](0,0) = 0.0; // u2[j](1,0) = 0.0; // u2[j](0,1) = 0.0; // u2[j](1,1) = 0.0; // } // forAll(l, j) // { // l[j](0,0) = 0.0; // l[j](1,0) = 0.0; // l[j](0,1) = 0.0; // l[j](1,1) = 0.0; // l2[j](0,0) = 0.0; // l2[j](1,0) = 0.0; // l2[j](0,1) = 0.0; // l2[j](1,1) = 0.0; // } vector2Field& blockX = blockT.internalField(); vector2Field& blockX2 = blockT2.internalField(); vector2Field blockB(mesh.nCells(), vector2::zero); vector2Field blockB2(mesh.nCells(), vector2::zero); // Inset equations into block Matrix blockMatrixTools::insertEquation(0, phi_realEqn, blockM, blockX, blockB); blockMatrixTools::insertEquation(1, phi_imgEqn, blockM, blockX, blockB); blockMatrixTools::insertEquation(0, phi_realEqn2, blockM2, blockX2, blockB2); blockMatrixTools::insertEquation(1, phi_imgEqn2, blockM2, blockX2, blockB2); forAll(d, i) { d[i](0,1) = d2[i](1,1); d[i](1,0) = d2[i](0,0); blockB[i][0] += blockB2[i][1]; blockB[i][1] = blockB2[i][0]; } forAll(u, j ) { u[j](0,1) = u2[j](1,1); u[j](1,0) = u2[j](0,0); } forAll(l, j ) { l[j](0,1) = l2[j](1,1); l[j](1,0) = l2[j](0,0); } // Block coupled solver call BlockSolverPerformance<vector2> solverPerf = BlockLduSolver<vector2>::New ( word("blockVar"), blockM, mesh.solver("blockVar") )>solve(blockX, blockB); solverPerf.print(); // Retrieve solution blockMatrixTools::blockRetrieve(0, phi_real.internalField(), blockX); blockMatrixTools::blockRetrieve(1, phi_img.internalField(), blockX); phi_real.correctBoundaryConditions(); phi_img.correctBoundaryConditions(); } volVectorField gradPhi_real = fvc::grad(phi_real); volVectorField gradPhi_img = fvc::grad(phi_img); # include "write.H" } Info<< "End\n" << endl; return(0); } I do not remember any details anymore. However, I remember that the solver worked nicely. I hope this helps, Christian 
hi, christian,
thanks soooo much for your kind reply! i understand your code generally, but i just have a question, in my equation, the coupling term is the gradient of p (in your equation, the coupling is the laplacian, and luckily OpenFOAM has the fvm::laplacian(), but they don't have fvm::grad()...that's my big problem!). do you also have any idea about this? 
Quote:

hi, chritian,
thanks all the same :) Tian 
HI, All
As I read your guys' reply, you are couple two equations maximum. Is there any example that we can couple more equations? like 3 or 4? thank you in advance 
Quote:
In which version of openfoam you compiled your solver? I want to solve some coupled transport equation and some one suggested me the blockCoupledScalarTransportFoam.C that is similar to your solver and I know this just work in extended version 3 and higher and not in version 2.2 
used version
Hello!
Well, that was a long long time ago when I worked on this solver :) I just checked my source code archive: I used OpenFoam1.6ext for this project. Christian 
Thanks christian:)

Quote:
I have the same problem somehow I want to solve dT/dt +d(Uk)/dx =0 dk/dt +d(UT)/dx =0 that are coupled and I have to use some tensors also thanks for the reply but in dimensionedTensor("jTensor", dimless, Foam::Tensor(0,1,0,1,0,0,0,0,0)) what is jTensor? because i have seen "0" somewhere I sthe "0" means 0 directory? 
Does anyone still following this topic?
I want to solve a coupled equation dT/dt + d/dx(Uk) = 0 dk/dt + d/dx(UT) = 0 for solving that volTensorField j ( IOobject ( "j", runTime.timeName(), mesh, IOobject::NO_READ, IOobject::NO_WRITE ), mesh, dimensionedTensor( "jTensor", dimless,tensor(0,1,0,1,0,0,0,0,0) ) ); and solving fvVectorMatrix TEqn ( fvm::ddt(f) == ( j & fvc::div(phi,f) ) ); TEqn.solve(); runTime.write(); and defined f as volVectorField f ( IOobject ( "f", runTime.timeName(), mesh, IOobject::MUST_READ, IOobject::AUTO_WRITE ), mesh ); forAll(f,I) { f[I].component(0)=T[I]; f[I].component(1)=kappa[I]; f[I].component(2)=0; } my code compiled correctly but my results are unexpected I am in doubt with f,I mean I am not sure what kind of boundary conditions I have to implement for a vectorfield that including two scalarfield(in this case T and kappa) 
how to program ddt(laplacian(T)) term?
hello everyone,
is there anybody still following this topic? I want to program the following PDE.: d2dt(T)=cost1*laplacian(T)+const2*ddt(laplacian(T) ), I think I should extract two coupled PDEs, ie. eq1=laplacian(T) d2dt(T)=cost1*eq1+const2*ddt(eq1) Is it true or not? and how to program it in OpenFoam? regards, Roozbeh 
All times are GMT 4. The time now is 21:07. 