# Does interFoam consider the inter-phase momentum transfer?

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 January 9, 2013, 23:06 Does interFoam consider the inter-phase momentum transfer? #1 Member   Jianye Xia Join Date: Mar 2009 Posts: 32 Rep Power: 10 Hi, Can anybody tell me does the interphase drag force considered in interFoam? And what the difference between bubbleFoam and interFoam? Thanks! Jianye

 January 10, 2013, 06:17 #2 Member   Andrea Join Date: Feb 2012 Location: Leeds, UK Posts: 98 Rep Power: 8 Hi Jianye, you can find the interFoam formulation in the Henrik Rusche's Ph.D. thesis. Andrea

 January 10, 2013, 15:53 #3 Senior Member   Kent Wardle Join Date: Mar 2009 Location: Illinois, USA Posts: 218 Rep Power: 14 No. There is one velocity field shared by all phases in interFoam and it's derviatives (multiphaseInterFoam). bubbleFoam (and twoPhaseEulerFoam) uses Euler-Euler so each phase has it's own velocity field and inter-phase momentum transfer is supplied via drag formulations. A newer solver, multiphaseEulerFoam, is unique in that it does Euler-Euler for an arbitrary number of phases (with inter-phase drag), but it can also impose a sharp interface a la interFoam on any phase pairs. Hope this is useful info. ziad, bioexplore and Andrea1984 like this.

January 10, 2013, 22:14
#4
Member

Jianye Xia
Join Date: Mar 2009
Posts: 32
Rep Power: 10
Thanks Andrea!

Quote:
 Originally Posted by Andrea1984 Hi Jianye, you can find the interFoam formulation in the Henrik Rusche's Ph.D. thesis. Andrea
But I think Henrik Rusche's Ph.D thesis dealing with bubbleFoam but not interFoam. Is this right? Can anyone know this give some explaination?

January 10, 2013, 22:21
#5
Member

Jianye Xia
Join Date: Mar 2009
Posts: 32
Rep Power: 10
Thanks Kwardle!

Quote:
 Originally Posted by kwardle No. There is one velocity field shared by all phases in interFoam and it's derviatives (multiphaseInterFoam). bubbleFoam (and twoPhaseEulerFoam) uses Euler-Euler so each phase has it's own velocity field and inter-phase momentum transfer is supplied via drag formulations. A newer solver, multiphaseEulerFoam, is unique in that it does Euler-Euler for an arbitrary number of phases (with inter-phase drag), but it can also impose a sharp interface a la interFoam on any phase pairs. Hope this is useful info.
You make it more clear!

What's my understanding is that (If I was wrong, please correct it!):
Because there is one share velocity field in interFoam, so there is no interphase momentum item derived in the UEqn, and the interface between liquid and gas is davanced by solving the alpha equation?
For bubbleFoam, the derived UEqns for each phase have the interphase momentum item, so when solving each phase's UEqn the interphase momentum item should also be given?

Is this correct?

 January 13, 2013, 17:10 #6 Senior Member   Ziad Boutanios Join Date: Mar 2009 Location: Montréal, Canada Posts: 119 Rep Power: 10 interFoam is a Volume of Fluid solver so it solves one set of mixture Navier-Stokes equations with a volume fraction scalar transport equation that determines which phase you're dealing with. It does not account for interphase momentum transport because it is simply not part of the VOF mixture formulation. It is described in Onno Ubink's PhD thesis, and definitely not Henrik Rusche's, as pointed out by kwardle. Check out equations 2.14 and 2.15 in Onno's thesis which can be found there http://powerlab.fsb.hr/ped/kturbo/Op...oUbbinkPhD.pdf In bubbleFoam (and twoPhaseEulerFoam) you solve a full set of NS equations for each phase and couple them with the momentum coupling term which includes drag, lift and virtual mass. Turbulence is done with k-epsilon on the mixture. bioexplore, vbnhfylbh, BlnPhoenix and 1 others like this.

 January 13, 2013, 20:48 #7 Member   Jianye Xia Join Date: Mar 2009 Posts: 32 Rep Power: 10 Hi, Ziad, Thanks very much for your clearly explaination, It makes me more clear about the difference between interFoam and bubbleFoam.

 January 13, 2013, 20:51 #8 Senior Member   Ziad Boutanios Join Date: Mar 2009 Location: Montréal, Canada Posts: 119 Rep Power: 10 You're quite welcome.

 January 28, 2013, 22:44 #9 Senior Member     Santiago Marquez Damian Join Date: Aug 2009 Location: Santa Fe, Santa Fe, Argentina Posts: 438 Rep Power: 17 Some clarifications, 1. Henrik Rusche's thesis deals both with VOF and Euler-Euler 2. VOF can be derived from Euler-Euler via the Mixture Model, giving which I call the Weller-VOF method, this explains why interFoam retains the relative velocity term in the alpha Eqn. and the necessity to go from volumetric flux formulation to mass flux formulation assembling the rhoPhi field. This is a key concept to understand the interFoam code. 3. As the guys told, the velocity is treated as a only one field in the momentum equations so that the interphase momentum exchange term vanishes (its expresion is , where is the relative velocity between phases p and q). I give a full explanation of these issues in my PhD thesis which is in review, it will be available for the community by the end of March, 2013. Regards. __________________ Santiago MÁRQUEZ DAMIÁN, Ph.D. Research Scientist Research Center for Computational Methods (CIMEC) - CONICET/UNL Tel: 54-342-4511594 Int. 7032 Colectora Ruta Nac. 168 / Paraje El Pozo (3000) Santa Fe - Argentina. http://www.cimec.org.ar

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Anne Severt OpenFOAM 1 November 27, 2013 05:15 volo87 CFX 5 June 14, 2013 17:44 Demonwolf Main CFD Forum 2 October 29, 2009 20:53 Luke F Main CFD Forum 1 April 25, 2008 16:49 earlc Main CFD Forum 0 September 23, 2005 20:26

All times are GMT -4. The time now is 15:52.

 Contact Us - CFD Online - Privacy Statement - Top