# IcoFoam Is it a NavierStokesEquation

 Register Blogs Members List Search Today's Posts Mark Forums Read

 September 10, 2008, 06:24 Hi, I try to analyse the ic #1 Member   Joern Bader Join Date: Mar 2009 Posts: 33 Rep Power: 10 Hi, I try to analyse the icoFoam Solver. The Solver solves the Equation: ddt(U)+div(phi,U)-Laplacian(nu,U)=-grad(p) this themes seems to be a Navier-Stokes-Equation but I miss an U at div(phi,U). The Navier-Stokes Equation I know sould be: ddt(U)+U*div(phi,U)-Laplacian(nu,U)=-grad(p) Does the U appear later in the discretisation or is it a variation of the Navier-Stokes-Equation? Thx, Jörn

 September 10, 2008, 08:33 No: the N-S equation that _you #2 Senior Member   Gavin Tabor Join Date: Mar 2009 Posts: 181 Rep Power: 10 No: the N-S equation that _you_ know is ddt(U)+U*div(U)-Laplacian(nu,U)=-grad(p) Since div(u)=0 we can rearrange this as ddt(U)+div(U*U)-Laplacian(nu,U)=-grad(p) The finite volume discretisation however linearises this by representing one of the U terms in div(U*U) as the flux phi, hence ddt(U)+div(phi,U)-Laplacian(nu,U)=-grad(p) We then need to iterate around a bit to take account of the fact that when U changes from this solution, phi must be updated... Clear now? Gavin

 September 10, 2008, 08:52 Thanks for the fast help. Thi #3 Member   Joern Bader Join Date: Mar 2009 Posts: 33 Rep Power: 10 Thanks for the fast help. This helps a lot. I didn't see the step: ddt(U)+U*div(U)-Laplacian(nu,U)=-grad(p) to ddt(U)+div(U*U)-Laplacian(nu,U)=-grad(p) Joern

 September 10, 2008, 09:24 Here it is, with subscript x,y #4 Senior Member   Niels Gjoel Jacobsen Join Date: Mar 2009 Location: Deltares, Delft, The Netherlands Posts: 1,759 Rep Power: 29 Here it is, with subscript x,y,z meaning differentiation and u,v,w being velocity components and U the vector: In the x-direction div(U * U) reads: (u * u)_x + (u * v)_y + (u * w)_z = u_x u + u u_x + u_x u + u v_y + u_z w + u w_z = u_x u + u_x u + u_z w + u*(u_x + v_y + w_z) = u_x u + u_x u + u_z w where the term in the bracket are identical to zero for incompressible flows, as it is your continuity equation. The same can be done for the other directions and you will have understood the step above. Best regards, Niels __________________ Please note that I do not use the Friend-feature, so do not be offended, if I do not accept a request.

 September 10, 2008, 10:29 Thx for your Help. I think #5 Member   Joern Bader Join Date: Mar 2009 Posts: 33 Rep Power: 10 Thx for your Help. I think I now understand the solver algorithm. Now I have to understand the discretisation ;) Joern

 November 26, 2008, 18:26 Hallo, i have a new problem #6 Member   Joern Bader Join Date: Mar 2009 Posts: 33 Rep Power: 10 Hallo, i have a new problem with the same topic I try to understand the sover sonicFoam. This solver solves the Equations: ddt(rho, U)+div(phi, U)-laplacian(mu, U)=-grad(p) and ddt(rho, e)+div(phi, e)-laplacian(mu, e)=-div(phi/rho)+mu*magSqr(symm(grad(U))) For me it looks like some kind of impulse and energy equation from the compressible Navier Stokes equations. Does someone know which equations sonicFoam solves or where i can find some literature about the algorithm an his mathematic roots? sorry for posting nearly the same question again, but i need the infos for my further work and i don't see it alone. thx, Joern

 November 27, 2008, 18:43 sonicfoam is a solver for comp #7 New Member   Mark Michael Join Date: Mar 2009 Location: Rostock, Germany Posts: 5 Rep Power: 10 sonicfoam is a solver for compressible ideal gas flow. That why the solver use the continuity-,momentum-, energy-, and ideal gas equation in its algorithm. look in the programmer's guide ! there is an nice tutorial named: "Supersonic flow over a forward-facing step" on page 58 ! http://foam.sourceforge.net/doc/Guid...mmersGuide.pdf

 June 15, 2009, 13:44 #8 Member   Joern Bader Join Date: Mar 2009 Posts: 33 Rep Power: 10 I reactivate this old thread, cause i have a question about the sonicFoam solver. sonicFoam is a solver with PISO loop for the compressible Navier-Stokes equations. I think i understand most of the solver but one think is not clear: if i set mu=0 in sonicFoam it solves the Euler Equations for a compressible, inviscid, perfect gas. (thats what i want to simulate) But there is a little difference. sonicFoam just looks at the inner energy e=T*Cv (just thermal energy). The Euler Equations (and also the Navier-Stokes) work with the energy e=T*Cv+1/2*mag(v)^2 (thermal energy + kinetic energy). why can the kinetic energy be ignored? And why is the the solver still consisten to the Euler-/Navier-Stokes Equations? thx for help, Joern

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post aap OpenFOAM Running, Solving & CFD 15 May 28, 2012 08:30 manuel OpenFOAM Running, Solving & CFD 8 September 22, 2010 04:10 kar OpenFOAM Running, Solving & CFD 3 February 20, 2008 06:20 msrinath80 OpenFOAM Bugs 6 November 19, 2007 18:35 ds2taieb OpenFOAM Installation 1 March 24, 2006 04:22

All times are GMT -4. The time now is 23:12.