" a negative cell volume error " when import into fluent
 

i am working on a 2d vawt ( structure and unstructured doamins ) simulation using mesh motion technique and pointwise for mesh generation.
however i am already double checked the orientation of the structured and made sure that unstructured domains are oriented to +z, i examine also the area ratio.
still get a negative cell volume error in fluent

Sent from my SM-N920C using CFD Online Forum mobile app

Please attach PW file for a rough idea to get to know the real problem
The problem could be unnoticed empty domains or blocks, or could be orientation error between structured and unstructured meshes

your email please so i can send it to you

Sent from my SM-N920C using CFD Online Forum mobile app

https://www.dropbox.com/s/bzpvgwq0tk...29-9pw.pw?dl=0

Sent from my SM-N920C using CFD Online Forum mobile app

I exported the grid to a cas file using File, export, CAE... in Pointwise V18.0R4.

I was able to import the cas file into fluent V18 without any reported negative cell volumes.

Are you setting the double precision option during fluent cas import?

I imported cas file into fluent V15, double percision without negative cell error but when i click calculate it is only calculate two iteration then it gives me negative cell volume error
- i am using S-A model
- velocity inlet 5m/s
- 0.0005 timestep

Sent from my SM-N920C using CFD Online Forum mobile app

One other thing that I noticed is that the two sliding interface connectors are sharing end nodes. Topologically, this makes the grid point at this location shared by both the rotating near field domain AND the stationary far field domain.

I suspect that as the solution is running, this grid point is getting rotated by the inner domain. Since this point is also used by the outer domain, the outer domain becomes distorted resulting in the negative cells.

You see this in Pointwise by rotating the near field domains a few degrees. The far field domain will become distorted.


One way to fix this:

• Select the large, near field domain and File, Save Selection... to Inner.pw
• File, New...
• File, Open... Inner.pw and Edit, Transform, Rotate... the interface connector by 180 degrees around (0,0,0)
• File, Save... Inner.pw
• File, New...
• File, Open... the original file
• Delete the large, near field domain and its outer (interface) connector.
• File, Open... (append) Inner.pw.
• Clean up the BCs and VCs

mr.david thanks so much for your support, that way is working well.



Sent from my SM-N920C using CFD Online Forum mobile app