CFD Online Logo CFD Online URL
Home > Forums > Siemens

Negative Density problem in starcd

Register Blogs Members List Search Today's Posts Mark Forums Read

LinkBack Thread Tools Display Modes
Old   January 23, 2009, 12:37
Default Negative Density problem in starcd
Posts: n/a
hi all

I am running transient analysis with pressure -pressure boundary condition. i have one pressure in and 4 outlets (i.e pressure- pressure boundary condition). At any time one outlet is pressure and the rest all are wall. the pressure outlet interchanges with respect to time. This can be compared with air Induction in IC engine i.e when intake valve is opened its pressure and when closed it changes to wall.The problem i am facing is that when the boundary changing from wall to pressure or vice versa i am getting Negative density at the boundary. Is the solver is unstable during the change of boundries. Is there any way to get rid of it. I am running in MARS mode for momentum and Temp. Could any one help in this regared....

I am using Starcd 3.26
  Reply With Quote

Old   January 23, 2009, 14:10
Default Re: Negative Density problem in starcd
Balduin Bankerotti
Posts: n/a
try underrelaxation of piso:

also piso node 20 0.15 0.8

  Reply With Quote

Old   January 23, 2009, 15:49
Default Re: Negative Density problem in starcd
Posts: n/a
- check .info file if the problem is temperature convergence: set residual tolerance for temperature and scalars to 1e-3

- save .pst every time step

- post process density to see which cells are -ve

- reduce the time step: if it still give -ve density: your mesh is no good.

  Reply With Quote

Old   January 26, 2009, 13:23
Default Re: Negative Density problem in starcd
Posts: n/a
and try UD at least initially....
  Reply With Quote

Old   January 26, 2009, 13:53
Default Re: Negative Density problem in starcd
Posts: n/a
Had you considered driving the model with velocity/massflow boundaries? The level of pressure does not set the mass in/out of the domain it is the gradient, which you are not setting.

Also instaneously changing the boundary type to wall will almost certainly cause problems. You are trying to stop any massflow from entering and leaving essentially instaneously, which will naturally cause a very large negative or positivepressure pulse.

If you are driving this with the output of one of the 1D engine flow solvers then you will have a lot better luck driving it with a massflow condition (or possibly coupling it in).
  Reply With Quote


Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
Negative density problem. compressible flow Karl Siemens 2 July 10, 2008 16:41
Negative Density Wendy Tjia Siemens 6 November 26, 2004 11:45
negative density Jane Siemens 4 March 9, 2004 22:01
Negative density Miriam Siemens 0 May 10, 2002 04:21
NEGATIVE DENSITY M. R. JAHANNAMA Main CFD Forum 8 September 29, 1999 23:59

All times are GMT -4. The time now is 13:35.