[arun7328]

Hi all

I am trying to create an overset mesh for a problem of cylinder falling into water. I did the mesh and when i initialize i get the error "found inactive faces in region background.Could be due to too coarse or fine. I have made sure that the region of overlap has the same mesh size and has more than 4-5 cells.

Can anyone please help me out with the error?

The cells in the outer of the overset mesh is of 0.1 m and that in the background symmetry plane is of 0.125 m. I have attached the mesh and status diagram..

Please tell me what i should check. I have tried to change the sizes and check but still i get the same error.

Regards
Arun

[arun7328]

just to add this is my cell status..the picture is better...

Pls give me a tip if you know how to get this right..

[lava12005]

Hi,

It seems from your Overset cell status the background value is 1 (red coloured) which means in-active and it shouln't be that way I suppose?
Maybe you should check whether you are assigning the correct overset boundary type to the correct boundary?
Or have you created the Overset Interface between the 2 domain?

[arun7328]

I have created the overset interphase between the two and when i try to initialize the interface it fails. Now with changing the mesh values of the 2 regions i have got to another error which says "failed to cut a hole..could be a problem with overlap"..but how to check this overlap..I have left enoung cells in the overlap region of both boundaries.

thanks
arun

[mmntmflx]

if you want, you can send your file to me.. i would like to see..

[arun7328]

ya sure ..i got it running now but after some time it displays an error the mesh might be too coarse or fine. Can i put it in the drop box? how can i share it with u?..my id is arun7328@gmail.com..if you gimme ur id i can share it with u...

Thanks a lot
Regards
Arun

[arun7328]

Originally Posted by grad@itu

if you want, you can send your file to me.. i would like to see..

how should i send the file?..I have got it running but after some time it gives the same error, that the mesh is coarse of fine..I am not able to figure out why because i have made sure that the overset does not cross boundary region and also the mesh sizes even during movement is comparable. The physics is happening correctly now.

Regards
Arun

[phanh]

Originally Posted by arun7328

how should i send the file?..I have got it running but after some time it gives the same error, that the mesh is coarse of fine..I am not able to figure out why because i have made sure that the overset does not cross boundary region and also the mesh sizes even during movement is comparable. The physics is happening correctly now.

Regards
Arun

Hi Arun,

Did you solve your problem? I have the similar error message. could you give me some advises for this issue?

Best regards

[arun7328]

Hi.

Yes I solved the problem. Not sure what you are facing though. The problem with my model was that the mesh sizes on the boundary of the overset and the background were not the same. They have to exactly similar. In my case overset boundary was 0.1m and back ground was 0.125. I changed both to 0.1 and it worked.

Hope it works for you, if not explain yours and we shall see what to do.

Regards
Arun

[phanh]

Hi Arun,

Thank you for taking your time. I also solved my problem.

Best regards

[EnronZhang]

Hi Arun,

I have the similar problem as you had before. Just wondering that the mesh sizes of overset and back ground should be exactly the same, does it mean the volume mesh or the surface remesh? Because I have made the volume meshes in the same sizes for both region, but it still did not work.

Many thanks.
Enron

Originally Posted by arun7328

Hi.

Yes I solved the problem. Not sure what you are facing though. The problem with my model was that the mesh sizes on the boundary of the overset and the background were not the same. They have to exactly similar. In my case overset boundary was 0.1m and back ground was 0.125. I changed both to 0.1 and it worked.

Hope it works for you, if not explain yours and we shall see what to do.

Regards
Arun

[arun7328]

Dear Zhang,

Its the volume meshes. What is the error message you are getting? Are you able to initialise the interface.

Regards
Arun

[dhaval]

I am running into same issue. In my case, background mesh has prism layers on the boundaries. When overset mesh enters into this prism layers, I get the error message. May be it is because prism mesh is smaller?

Background mesh size: 1.25 mm
Size of first prim layer in background mesh: 0.77 mm
Overset mesh size: 1 mm

I am not sure if the error message (mesh is either too small or too coarse) is due to two surfaces coming too close or because of size difference. I run another simulation with following sizes and it run without any problem (background: 1.45, prism: 0.85, overset: 1)

[ggulgulia]

Hi Everybody

From the images posted above, it was obvious that the cells were not intersecting properly. The best method to avoid this is to use mesh size in the Background Region nearly 1.5 times the mesh size in the Overset Region.

[withwolf]

I'm facing the same problem. It turns out that I forgot to set the overset interface interpolation option to "linear".

[rahulpawar]

Hi all

I am also running in to same problem. I have maintained background mesh size and overset mesh size same at boundaries, still problem exist. any guess what could be the reason?

[coni]

hi all,

I have a problem in overset mesh with orphan cell. I tried some alternatives but still there are orphan cells in my case. How i can get rid of orphan cells ?
Do you have an idea ?

Thank you for interest,

King regards