CFD Online Discussion Forums

CFD Online Discussion Forums (https://www.cfd-online.com/Forums/)
-   STAR-CCM+ (https://www.cfd-online.com/Forums/star-ccm/)
-   -   Boundary condition for free convection (https://www.cfd-online.com/Forums/star-ccm/124952-boundary-condition-free-convection.html)

the new one October 16, 2013 04:40

Boundary condition for free convection
 
Hi
What are the suitable boundary condition for free convection in starccm+. I am trying to simulate natural convection of a sphere in open atmosphere. so my thought was that freestream conditon all around with very low velocity and boundaries at a very large distanec would work but it dooesnt seem to give physical results. Any suggestions.I have also already triend with adiabatic walls at a large distance.
any suggestions or your experiences with such problems will be appreciated.
Thanks

Cobra June 13, 2017 11:49

I know this answer is coming pretty late, but I think it still may be useful for someone looking for it.
You should build a spherical domain around your object, with a diameter 3 to 5 times the major diagonal of the object.
Boundary condition should be 'Pressure Outlet'. As pressure you should probably set Field Function 'Pressure' (not 100% sure here, but for me it worked most of the times).
When I tried to use a bigger domain (say 20 times the major diagonal) the solution couldn't converge.
I already posted some question in the forum about this specific problem.

me3840 June 15, 2017 14:44

Quote:

Originally Posted by Cobra (Post 653047)
Boundary condition should be 'Pressure Outlet'. As pressure you should probably set Field Function 'Pressure' (not 100% sure here, but for me it worked most of the times).


Don't do this. The field function 'pressure' is solved for. The whole point of a pressure condition is to specify the pressure. You can make your own field function named pressure and use that, but do not use the internal field function pressure. I don't think it makes any sense to do that.

Cobra June 16, 2017 05:29

I agree, I was wrong in my previous reply. In the Adapco website I found a guide to set the boundary conditions for open air natural convection

https://thesteveportal.plm.automatio...S/FAQ/RD-5-112

From what I understood the Field Function should be written as:

-1.18*9.81*$$Position[2]*((300/$Temperature)-1)

where 1.18 is representing the reference density.

Right now I'm waiting for a renewal of my licence so I can't test its validity.

cwl June 16, 2017 09:17

How do you people get access to StevePortal? - Only via purchasing the license?

me3840 June 18, 2017 22:57

Remember that function requires you set your z=0 value to be the altitude where the piezometric pressure is the same as the static pressure.


All times are GMT -4. The time now is 00:18.