# Wave reflection from inlet

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 LinkBack Thread Tools Search this Thread Display Modes
 May 5, 2014, 14:11 Wave reflection from inlet #1 Member   David Join Date: Nov 2011 Posts: 39 Rep Power: 13 Dear All, when simulate a DFBI case with wave, motion of the structure radiate wave to the inlet, and the inlet will reflect the radiated wave to the structure. so, does any one know how to eliminate the wave reflection from the inlet? Thanks in advance.

 May 6, 2014, 10:27 #2 Senior Member   Join Date: Nov 2010 Location: USA Posts: 1,232 Rep Power: 23 You need to dampen the wave near the BC. There's a setting for this, check the user guide.

May 6, 2014, 10:45
#3
Member

David
Join Date: Nov 2011
Posts: 39
Rep Power: 13
Quote:
 Originally Posted by me3840 You need to dampen the wave near the BC. There's a setting for this, check the user guide.
Hi me3840, thank you for your answer. I know the reflection from the outlet can be dampened by setting damping. But my question is the reflection from the inlet. If a damping zone is set between the inlet and the structure, the incident wave will never reach the structure.

 May 6, 2014, 10:48 #4 Senior Member   Join Date: Nov 2010 Location: USA Posts: 1,232 Rep Power: 23 Hm. I don't think that's possible. Under what circumstance would the wave not reflect in real life?

 May 7, 2014, 06:19 #5 Member   David Join Date: Nov 2011 Posts: 39 Rep Power: 13 the problem is the real life do not have a "domain". Reflection is caused by ''domain'' effect.

 May 7, 2014, 06:57 #6 Member   Roman Join Date: Mar 2011 Posts: 46 Rep Power: 13 Damping zone is a poor solution if you are sending in waves through it. If you have large problems with reflection then your domain is probably to small in the first place. Could you perhaps increase the distance from the inlet and dampen all the other walls?

May 7, 2014, 07:11
#7
Member

David
Join Date: Nov 2011
Posts: 39
Rep Power: 13
Quote:
 Originally Posted by Roman Damping zone is a poor solution if you are sending in waves through it. If you have large problems with reflection then your domain is probably to small in the first place. Could you perhaps increase the distance from the inlet and dampen all the other walls?
Hi Roman

Thank you for your answer. Yes, it is ture that we can relief the reflection from inlet by extending the domain. However, extending the domain will cause 2 problems. 1) computation resource will increase extensively. 2) wave decay caused by mesh.

It is a solution but not good enough.

 May 7, 2014, 07:48 #8 Senior Member   Ping Join Date: Mar 2009 Posts: 556 Rep Power: 18 you will get almost zero wave decay if you follow the guidelines for capturing waves well like 20 cells trough to peak and 40-80 per wave length using good anisotropic refinement with the trimmer mesher and to save cells use very wide cells until you get near your structure and use second order time and ensure the courant number is below 1 in the wave by getting the time step low enough and the little decay you do get can be adjusted by making the wave a little larger at inlet

 May 7, 2014, 07:57 #9 Member   Roman Join Date: Mar 2011 Posts: 46 Rep Power: 13 1. Very true, however, by creating smart grid refinements this should not be extremely computationaly expensive. 2. AS for grid goes, I'm unsure if you are simulating on VOF wave or not. If you do: Set your Z size to about 1/20th of the wave amplitude. Set your second order unsteady solver time step relatively to the wavelength division chosen, using the following equation: if the dx chosen was 1/80th, then use (wave period) / (2.4 * 80), if it was 1/90th, use (wave period) / (2.4 * 90), and so forth. Be careful to not create unrealistically steep waves. For example, the 1st order wave theory applies to waves with amplitudes to wave length of around 1:100. Shorter times steps are required in some steep wave cases where the turbulent kinetic energy might diverge. EDIT: ping beat me to it

 May 7, 2014, 07:59 #10 Member   David Join Date: Nov 2011 Posts: 39 Rep Power: 13 Hi ping, thank you for your answer. Yes I know that. However, I don't belive you can get almost zero decay in wave tank direction. Of course for time history, there's almost no decay when close to the inlet. BTW, to use second order time you need to make sure the courant number is smaller than 0.5 rather then 1.

 May 7, 2014, 08:03 #11 Member   David Join Date: Nov 2011 Posts: 39 Rep Power: 13 Thanks Ping, Roman. I am waitting for an anwser like "EOM" method. Which is far more efficient than the current solution. Do you guys know about it?

 May 7, 2014, 08:13 #12 Member   Roman Join Date: Mar 2011 Posts: 46 Rep Power: 13 Could you elaborate a little further? What are you trying to simulate, is it a boat in waves and you are trying to analyze response? I agree with ping, cases with little to no grid damping are possible, it's a mater of computational cost.

 May 7, 2014, 08:22 #13 Senior Member   Ping Join Date: Mar 2009 Posts: 556 Rep Power: 18 we have several cases with essentially no decay after more than 10 wave passes so it is possible with care and i suggest you create a one cell wide model to show this youself oem stands for euler overlay method i think and i have heard that this will be added to the software to allow efficient creation of much larger domains together with a better wave damping method using a solution forcing technique but i have no idea when

May 7, 2014, 08:27
#14
Member

Roman
Join Date: Mar 2011
Posts: 46
Rep Power: 13
Quote:
 Originally Posted by ping oem stands for euler overlay method i think and i have heard that this will be added to the software to allow efficient creation of much larger domains together with a better wave damping method using a solution forcing technique but i have no idea when
They mentioned that "forcing technique" will come in version that will be released this summer.

 May 9, 2014, 10:36 #15 Member   David Join Date: Nov 2011 Posts: 39 Rep Power: 13 Are you sure? This will be fantastic

 May 9, 2014, 10:39 #16 Member   David Join Date: Nov 2011 Posts: 39 Rep Power: 13 Do you mean 10 wave lengths away from the velocity inlet or at a certain point which is close to the inlet experienced 10 waves?

March 25, 2019, 16:54
#17
New Member

Tanvir Sayeed
Join Date: Jan 2015
Posts: 9
Rep Power: 9
Quote:
 Originally Posted by Roman 1. Very true, however, by creating smart grid refinements this should not be extremely computationaly expensive. 2. AS for grid goes, I'm unsure if you are simulating on VOF wave or not. If you do: Set your Z size to about 1/20th of the wave amplitude. Set your second order unsteady solver time step relatively to the wavelength division chosen, using the following equation: if the dx chosen was 1/80th, then use (wave period) / (2.4 * 80), if it was 1/90th, use (wave period) / (2.4 * 90), and so forth. Be careful to not create unrealistically steep waves. For example, the 1st order wave theory applies to waves with amplitudes to wave length of around 1:100. Shorter times steps are required in some steep wave cases where the turbulent kinetic energy might diverge. EDIT: ping beat me to it
@Roman:
Hi Roman, I am able to generate my desired wave (steepness 1/20), but when I put the body in waves, the turbulent energy and dissipation rates diverging. Apparently it seems like I may have to use very small timestep than the one I used to generate waves or first order temporal may work which reduces the wave height. Any suggestion will be appreciated.

March 29, 2019, 00:46
Retrieve the simulation file
#18
Member

sriram
Join Date: Jun 2016
Posts: 48
Rep Power: 8
I was running a simulation, the power went off but the system was backed up by UPS. I saved the simulation after some time the file is not opening and it pops up the message "Apparently, the original save action did not terminate successfully". How to retrieve my simulation???? Any ideas?
Attached Images
 Star ccm termination error.jpg (104.6 KB, 14 views)

 Thread Tools Search this Thread Search this Thread: Advanced Search Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are Off Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Pumbam CFX 1 July 16, 2017 03:01 phys-zephyr STAR-CCM+ 3 May 8, 2014 06:46 mark_l CFX 3 February 17, 2010 17:57 aeroman CFX 12 August 6, 2009 19:42 Enoch FLUENT 0 July 14, 2005 17:41

All times are GMT -4. The time now is 06:01.

 Contact Us - CFD Online - Privacy Statement - Top