CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] Uniform mesh in ICEM

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   February 4, 2011, 09:39
Question Uniform mesh in ICEM
  #1
New Member
 
Join Date: Jan 2010
Posts: 15
Rep Power: 6
harerton is on a distinguished road
Hi everybody,

How do I get a uniform mesh with hexa elements of the same size in ICEM?

My domain has rectangular faces and all the elements are organized so that hexa elements with 2cm side would fit properly.

What are the correct parameters to be used?

Thanks!
harerton is offline   Reply With Quote

Old   February 4, 2011, 10:55
Default
  #2
Senior Member
 
AB
Join Date: Sep 2009
Location: France
Posts: 323
Rep Power: 12
BrolY will become famous soon enough
Play with the "Edge Params" option (blocking -> Pre Mesh Params -> Edge Params).
BrolY is offline   Reply With Quote

Old   February 5, 2011, 14:18
Default Automatic option...
  #3
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,650
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Or you could try an automatic Cartesian method such as BFCart...

Can you post an image or maybe even your model and I could illustrate...
PSYMN is offline   Reply With Quote

Old   February 5, 2011, 23:21
Default
  #4
New Member
 
Join Date: Jan 2010
Posts: 15
Rep Power: 6
harerton is on a distinguished road
I have attached the model.

The flow enters the domain through an inlet at one extremity, near some obstacles and exit through the other extremity.There's a cubic obstacle downwind the domain. The geometry parts are: INLET, OUTLET, RIGHT, LEFT, TOP and WALLS (which includes the floor and the obstacles surfaces).

What I do in ICEM:

1 - Import the geometry
2 - Create the parts
3 - In Mesh - Global Mesh setup:

a) Global Mesh Parameters: Global element seed size = 0.02m;
b) Shell meshing parameters: Mesh type = All Quad; mesh method = autoblock;
c) Volume mesh parameters: Mesh type = cartesian; mesh method =body-fitted; Aspect ratio 1 1 1;

4 - Compute volume mesh.

The generated mesh is all hexa, but the elements don't have all the same size on each face, while some of them aren't even cubes. Their faces are less than 0.02m.

I would like to get a mesh where every element is a cube with a 0.02m side!

Thanks for any help!
Attached Files
File Type: zip 700-100-100.zip (16.3 KB, 15 views)

Last edited by harerton; February 6, 2011 at 06:33. Reason: adding domain and geometry descriptions
harerton is offline   Reply With Quote

Old   February 19, 2011, 20:14
Default BFCart.
  #5
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,650
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
You mixed two methods that don't mix. The Cartesian method is a top down method, which means you don't need to start from a surface mesh.

I will attach my tetin file of your model.

Like you, I setup parts and set all the sizes (including the global max size) to 0.02.

Then I made sure the Cartesian meshing parameters were setup and meshed with BFCart...

I got this. (Cutplane shown)

Harerton_BFCart.jpg

I have to say that I think this is not very efficient. Most users prefer to have more elements in the important areas and fewer elements in the less important areas. Uniform density is not what most people are looking for.

This could be very much improved by creating your own cartesian back ground grid with hexa (like is done in the femur tutorial).

If you want, you could also try Octree Tetra followed by a tet to hex conversion (very easy and popular way of getting hexa dominant mesh that transisitions well, converges well, etc.), or perhaps go for full blown hexa blocking (by far the best solution if your real model is this simple).
Attached Files
File Type: zip 700-100-100_BFCART.zip (6.2 KB, 12 views)
PSYMN is offline   Reply With Quote

Old   February 20, 2011, 08:25
Default
  #6
New Member
 
Join Date: Jan 2010
Posts: 15
Rep Power: 6
harerton is on a distinguished road
Quote:
Originally Posted by PSYMN View Post
If you want, you could also try Octree Tetra followed by a tet to hex conversion (very easy and popular way of getting hexa dominant mesh that transisitions well, converges well, etc.), or perhaps go for full blown hexa blocking (by far the best solution if your real model is this simple).
Thank very much for your answer. I know uniform is not the best alternative. But I was trying to find a way to generating it.

Anyway, where do I find this femur tutorial? And are there tutorials for these two alternatives you suggested above (see quote)?

Thanks again!
harerton is offline   Reply With Quote

Old   February 21, 2011, 00:08
Default Tutorial.
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,650
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
This is a pretty old tutorial (2008 I think)... It was one I quickly put together for a hands on session at a conference... I got some complaints that i didn't include enough detail, such as how to use subsets to get the cutaway mesh views...

But hopefully you still get something out of it.

I think later the doc people turned it into a real tutorial and put it into the customer portal... You can look for that if you want, but here is my original.

ftp://ftp.ansys.com/outgoing/simon/ICEMCFD_Femur.zip

In this tutorial, instead of letting the software create its own cartesian background mesh, you can create it... This means you can align it perfectly with your far field (and not have it distort as it projects to surface). You can also used edge parameters to bias along the duct and reduce your mesh count in one direction...

Have fun.
PSYMN is offline   Reply With Quote

Old   February 21, 2011, 05:16
Default
  #8
New Member
 
Join Date: Jan 2010
Posts: 15
Rep Power: 6
harerton is on a distinguished road
Thanks! Will take a look!
harerton is offline   Reply With Quote

Old   February 22, 2011, 06:32
Default
  #9
New Member
 
Join Date: Jan 2010
Posts: 15
Rep Power: 6
harerton is on a distinguished road
Simon,

Thank you very much for all your help. With the aid of your tutorial I was able to understand more of how ICEM works and I was able to produce a much more improved mesh.

Thanks again and keep up the good work!

Harerton
harerton is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
second order schemes marine OpenFOAM 65 July 31, 2014 08:02
[ICEM] Unstructure Meshing Around Imported Plot3D Structured Mesh ICEM kawamatt2 ANSYS Meshing & Geometry 17 December 20, 2011 11:45
ICEM Tetra mesh, Size reduction and Skewness problem Catthan ANSYS Meshing & Geometry 6 December 5, 2010 19:39
Boddy fitted Hexcore Mesh in ICEM Cfd Mitch CFX 0 December 29, 2008 06:07
Gambit problems Althea FLUENT 21 February 6, 2001 07:05


All times are GMT -4. The time now is 07:22.