Need to measure transient pressure at one moving point

fated-oracle · October 17, 2011, 11:43

Hi!

I'm currently stuck with my simulation so I would be really grateful if anyone could help me. I'm simulating the dropping of a wedge onto the free water surface. I've been using the rigid body solution for the wedge (it is in fact only a beta feature in Ansys v12.1, which is the only available at uni) and the interphase between the two fluids is modelled as a free surface. The simulation is obviously transient. In fact, the tools I used and my set up seem to work all right, as I can see from the keyframes of the pressure and water volume fraction distributions. However, what I need in fact in order to validate my results is the pressure for all time steps at a specific point that lies on the wedge surface. However, the problem is that this surface moves along (in the negative y direction) with the rigid body (wedge). Hence, I cannot specify a signle point by inputting the coordinate files. However, what I could do is to model the mesh so that I have a node lying on the surface exactly in the location I need the pressure measurements to be taken at. Nevertheless, I don't know what to call this point in Ansys CFX-Pre.
If anyone knows how to deal with this or has a different idea I'd be really grateful. thank you in advance!

gpwakeham · November 15, 2011, 04:01

does it have to be at one specific point? Because instead you could monitor an area average of the pressure at the bottom surface, for example

areaAve(pressure)@bottom

where bottom is the bottom face of the wedge

ghorrocks · November 15, 2011, 04:22

This is probably easiest done in post processing where you can extract the pressure at a series of points which represents the motion of your sensing point as the body moves. It means you will have to produce lots of results files but if you only include the variables you are interested in (and the mesh as it is moving) they should not be too big.

D.B · November 15, 2011, 05:31

To add to ghorrocks' point, what you could do is, simply define a point on the body, by either node number or variable max/min ( use X,Y,or Z as the variable) and then just export the data for each time step.

-D.B

stumpy · November 15, 2011, 09:51

I think you can just use a standard monitor point. Even though you enter x,y,z coordinates for monitor points, they get associated to the closest node (see the .out file). The values reported are for that node, so it moves with the mesh. If you perform re-meshing then you'd need a new monitor point.

ghorrocks · November 15, 2011, 19:26

Run-time monitor points snap to the nearest node, but post-processing points interpolate to the point location.

D.B · November 15, 2011, 23:00

Hi,
The best way to do is to figure out the co-ordinates of the point at the initial point of time (initial location), then create a point there. When you do that, you can see the nearest node number below that. Now Just select the Node number option in point deifinition and mention that specific node number you noted earlier, and then start lodaing the timesteps and exporting the data. I don't think you can use this method in pre, otherwise you could have created a monitor point at that node location. The post method is tedious but doable.

October 17, 2011, 11:43	Need to measure transient pressure at one moving point	#1
fated-oracle New Member Enrico Anderlini Join Date: Oct 2011 Location: Southampton Posts: 4 Rep Power: 14	Hi! I'm currently stuck with my simulation so I would be really grateful if anyone could help me. I'm simulating the dropping of a wedge onto the free water surface. I've been using the rigid body solution for the wedge (it is in fact only a beta feature in Ansys v12.1, which is the only available at uni) and the interphase between the two fluids is modelled as a free surface. The simulation is obviously transient. In fact, the tools I used and my set up seem to work all right, as I can see from the keyframes of the pressure and water volume fraction distributions. However, what I need in fact in order to validate my results is the pressure for all time steps at a specific point that lies on the wedge surface. However, the problem is that this surface moves along (in the negative y direction) with the rigid body (wedge). Hence, I cannot specify a signle point by inputting the coordinate files. However, what I could do is to model the mesh so that I have a node lying on the surface exactly in the location I need the pressure measurements to be taken at. Nevertheless, I don't know what to call this point in Ansys CFX-Pre. If anyone knows how to deal with this or has a different idea I'd be really grateful. thank you in advance!

Similar Threads
Thread	Thread Starter	Forum	Replies	Last Post
Pulsatile pressure inlet with pressure outlet	a.lynchy	FLUENT	3	March 23, 2012 13:45
Transient post-processing, Time averaged pressure work	Turbomachine	CFX	1	January 3, 2011 17:01
Make a point moving...URGENT	Shanti	FLUENT	0	June 2, 2007 20:14
Loading transient data of moving grid	leo	Siemens	3	April 9, 2003 01:35
Hydrostatic pressure in 2-phase flow modeling (long)	DS & HB	Main CFD Forum	0	January 8, 2000 15:00

November 15, 2011, 04:01		#2
gpwakeham New Member George Wakeham Join Date: Sep 2011 Posts: 5 Rep Power: 14	does it have to be at one specific point? Because instead you could monitor an area average of the pressure at the bottom surface, for example areaAve(pressure)@bottom where bottom is the bottom face of the wedge

November 15, 2011, 04:22		#3
ghorrocks Super Moderator Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 17,703 Rep Power: 143	This is probably easiest done in post processing where you can extract the pressure at a series of points which represents the motion of your sensing point as the body moves. It means you will have to produce lots of results files but if you only include the variables you are interested in (and the mesh as it is moving) they should not be too big.

November 15, 2011, 05:31		#4
D.B Member DB Join Date: Apr 2011 Posts: 87 Rep Power: 15	To add to ghorrocks' point, what you could do is, simply define a point on the body, by either node number or variable max/min ( use X,Y,or Z as the variable) and then just export the data for each time step. -D.B

November 15, 2011, 09:51		#5
stumpy Senior Member Join Date: Apr 2009 Posts: 531 Rep Power: 21	I think you can just use a standard monitor point. Even though you enter x,y,z coordinates for monitor points, they get associated to the closest node (see the .out file). The values reported are for that node, so it moves with the mesh. If you perform re-meshing then you'd need a new monitor point.

November 15, 2011, 19:26		#6
ghorrocks Super Moderator Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 17,703 Rep Power: 143	Run-time monitor points snap to the nearest node, but post-processing points interpolate to the point location.

November 15, 2011, 23:00		#7
D.B Member DB Join Date: Apr 2011 Posts: 87 Rep Power: 15	Hi, The best way to do is to figure out the co-ordinates of the point at the initial point of time (initial location), then create a point there. When you do that, you can see the nearest node number below that. Now Just select the Node number option in point deifinition and mention that specific node number you noted earlier, and then start lodaing the timesteps and exporting the data. I don't think you can use this method in pre, otherwise you could have created a monitor point at that node location. The post method is tedious but doable.