
[Sponsors] 
March 24, 2012, 00:37 
wall function

#1 
Member
Join Date: Aug 2011
Posts: 53
Rep Power: 6 
"The basic idea behind the scalable wallfunction approach is to limit the y* value used in the logarithmic formulation by a lower value of 11.06 is the intersection between the logarithmic and the linear near wall profile"
These are the statements from help files of cfx. The lower limit of y* is restricted to 11.06,does this mean that the linear near wall profile is neglected? "Do not use Standard Wall Functions unless required for backwards compatibility." These are the statements from help files of cfx. what is backward compatibility? I am trying to simulate a heat transfer problem, how does scalable wall function affect the results? my 

March 25, 2012, 06:48 

#2  
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
Quote:
Quote:
Quote:


March 25, 2012, 08:58 

#3 
Member
Join Date: Aug 2011
Posts: 53
Rep Power: 6 
Thanks Glenn.
Would u pl. explain me how does doubling and quadrupling the number of nodes(for grid independent study) and scalable wall function work together? 

March 25, 2012, 17:59 

#4 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
Most CFD packages use standard wall functions, and these are only valid for y+>11 or so. So if you start off with a mesh with y+=30, then half the mesh element length you get y+=15 (so far so good) but the next refinement gives you y+=7.5. The standard wall function approach is not valid for this value of y+, so you will get a finer mesh solution but it will not be physically correct as you are applying inappropriate wall functions.
The scalable wall functions help here because as you refine to below y+=11 it transitions to integrating to the wall. This keeps the wall functions physically valid and means you can do mesh refinement more easily. 

March 25, 2012, 23:09 

#5 
Member
Join Date: Aug 2011
Posts: 53
Rep Power: 6 
Thanks again Glenn.
As i understand, the Scalable wall functions are better to use for grid independent study also. is this correct? 

March 25, 2012, 23:12 

#6 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
Isn't that what I just said?


March 26, 2012, 03:21 

#7 
Member
Join Date: Aug 2011
Posts: 53
Rep Power: 6 
Thank u Glenn


March 26, 2012, 04:53 

#8  
Super Moderator
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,993
Blog Entries: 6
Rep Power: 39 
Quote:
Transition to linear profile is property of hybrid wall functions (aka automatic wall treatment in CFX) Scalable wall function are designed to avoid the problems 1. With mesh refinement when Y+ goes to 1. In this case standard wall function approach ceases to be valid. 2. At separation when velocity is zero and Y+ is again very low, in this case standard wall function ceases to be valid. In other words scalable wall function is robust wall function as compared to standard wall function. Standard wall functions are also valid up to Y+ = 11.06 and it was the default option in Fluent when Y+ is higher than 11.06. See the SA model section of Fluent User guide (I know this is CFX forum ) 

March 26, 2012, 05:01 

#9 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
Thanks for the correction Far. I have just read the documentation to confirm this time
Scalable wall functions effectively limit the y+ to 11. When y+<11 it sets y+=11 and therefore assumes the first node is outside the log layer. Automatic wall functions are what I was confused with, they transition from wall functions to integrating to the wall over the y+=11 threshold. 

March 26, 2012, 07:06 

#11 
Member
Join Date: Aug 2011
Posts: 53
Rep Power: 6 
Thank u Glenn and Far,
Does this mean that for forced convection heat transfer problem K epsilon  scalable wall function are not correct to use? 

March 26, 2012, 18:00 

#12 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
It is rare that a turbulence model is "right" or "wrong". They are all different with different strengths and weaknesses.
But in general the SST turbulence model is the default choice. It allows easy extension for some advanced models like automatic wall functions, curvature correction, transition model and others. ke I would only recommend if you are comparing to published data, it is largely superseded by SST in my opinion. RSM should be considered then anisotropic turbulence is significant, and LES style models (inc SAS, DES) for when you have large scale vortex shedding which you need to resolve. 

June 28, 2012, 09:45 
Standard wall function and SAS model

#13  
Member
Mina
Join Date: Apr 2011
Posts: 88
Rep Power: 6 
Quote:
You told When y+<11 it sets y+=11 and therefore assumes the first node is outside the log layer, you mean for y+< 11 it assumes u+=y+ (linear approach)? in CFX when you select SASSST model it automaticly selects standard wall function , while from your discussion i learned that scalable wall function is a better choice. However i can't do anything for that because it will be selected automaticly. so in this case (standard wall function) i have to take care of the mesh and should refine it well close to the wall, am i right? the y+ in my geometry (a combustor) is changing in the range of y+<40. so can you please tell me according to this wall function (standard) and this turbulence modell (sassst) which i used my mesh is good enough close to the wall? Regards Mina 

June 28, 2012, 11:24 

#14  
Super Moderator
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,993
Blog Entries: 6
Rep Power: 39 
Quote:


June 28, 2012, 15:21 

#15  
Member
Mina
Join Date: Apr 2011
Posts: 88
Rep Power: 6 
Quote:
Thanks Far! 1 in CFX the default for the sas model is standar model. But what is your idea about the range of y+ in my mesh? is it fine enough? and how does the software take care of y+<11? 2 how can we know for a certain turbulence model how big y+ can be or how much it can vary? Regards Mina 

June 28, 2012, 18:29 

#16 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
I am not sure what wall boundary conditions SAS uses, you will have to look that up.
Not only do different turbulence models have different requirements but different flow regimes have different requirements. So the only way to be sure is to do a mesh refinement sensitivity study on your configuration. 

June 29, 2012, 06:03 

#17  
Member
Mina
Join Date: Apr 2011
Posts: 88
Rep Power: 6 
Quote:
Thanks But can you explain what happens for y+<11 (in standard wall function)? I guess that turbulence equatuion will be integrated untill the wall in th eregion with y+<11, Is that true? or simply for the small y+ it assumes u+=y+ (linear approch and not logaritmic approach)? i am a bit confused with this layers 

June 29, 2012, 07:52 

#18 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
If you are using standard wall functions then the wall function equation will be used regardless of y+. Refer to the CFX documentation or a turbulence textbook like Wilcox for details on this. But the key point is that the wall function equation is only applicable from around y+>11. So if you apply standard wall functions with y+<11 then you are simply applying them in a regime where they are not accurate.


June 29, 2012, 08:49 

#19 
Super Moderator
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,993
Blog Entries: 6
Rep Power: 39 
Actually there is change in definition of u+. so instead of u+, u* is used for the scalable wall function. see documentation.


June 29, 2012, 08:54 

#20 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,053
Rep Power: 86 
I think the question was what happens for standard wall functions.


Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
channelFoam for a 3D pipe  AlmostSurelyRob  OpenFOAM  3  June 24, 2011 13:06 
Wall function for velocity?  johnblund  OpenFOAM  0  March 10, 2011 09:50 
BlockMesh FOAM warning  gaottino  OpenFOAM Native Meshers: blockMesh  7  July 19, 2010 14:11 
Need some wall function approaches!  yka8150  Main CFD Forum  0  September 21, 2009 23:08 
Problem with rhoSimpleFoam  matteo_gautero  OpenFOAM Running, Solving & CFD  0  February 28, 2008 07:51 