# square cavity?

 Register Blogs Members List Search Today's Posts Mark Forums Read

 September 16, 1999, 05:45 square cavity? #1 chaker Guest   Posts: n/a Hello, I m working on natural convection in a 2-D square cavity. It s differientially heated by a hot left and cold right vertical wall. Horizontal walls are adiabatic (the problem is well known in literature). I m studying the turbulence case (Rayleigh=5.10^5) using k-epsilon model and wall fonction. I find a big problem in the two corners (up-left) and (down-right). In fact, at these places, a numerical viscosity appear, velocity is irregular, temperature is not stratified,whereas the flow in the other parts of the cavity is good (velocity, temperature, turbulent viscosity). convergence is very slow. if I allow a long iteration time, I find bad result in all the cavity !! So please could you give me some advises??? my email is: celamrani@student.ulg.ac.be thanks a lot

 September 17, 1999, 04:07 Re: square cavity? #3 Jin Wook LEE Guest   Posts: n/a As you said, your problem is very well known one. I myself have had some experience for the entirely same problem, about 14 years ago, but for laminar case. As far as I remember, your problem, for Ra=5.e05, should be laminar natural convection. I remember that natural convective flow in a square cavity is considered as laminar till Ra is order of 1.e06 and turbulent when Ra is greater than order of 1.e08. My suggestion is, try your simulation with higher Rayleigh number, say, 1.e08. Be careful that thermal boundary layer is very narrow, so that enough grids should be located in the thermal boundary layer. As far as I remember, thermal boundary layer, del/H, is order of Ra^(-1/4). If you need more information, please send e-mail me. I might have good reference in my old shelf which I guess I can find. Sincerely, Jinwook

 September 17, 1999, 05:34 Re: square cavity? #4 chaker Guest   Posts: n/a Sorry, I make a mistake in my text, In fact I simulate a fully turbulent regime with Ra=5. 10^10 and not Ra=5. 10^5. Mister C.Chien, would you like to explain me little more the relaxation technic ?? thanks a lot

 September 19, 1999, 18:10 Re: square cavity? #5 Mahesh Prakash Guest   Posts: n/a Dear Chaker, I have studied your problem at the same Rayleigh number. Well as you might have understood by now, the problem is quite finicky numerically. Try using a very fine mesh close to the wall (not required if you are using the standard k-e model with wall functions. However for such flows it has already been shown that the wall functions used for forced convection flows cannot be applied) if you are using a low Re k-e model. If you want a reliable converged solution go for a transient medthod eventhough the final solution is steady. Also use an underrelaxation factor of 0.2 for all variables to be on the safer side. Please do not use the central difference schemne. I would suggest you to use either the hybrid or the QUICK scheme. All the best

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post McCarra OpenFOAM Programming & Development 1 January 14, 2011 10:23 arou FLUENT 2 September 22, 2010 08:26 Dhileep Main CFD Forum 0 January 11, 2009 11:29 john Main CFD Forum 0 September 30, 2005 07:40 rvndr Main CFD Forum 6 February 25, 2004 11:35

All times are GMT -4. The time now is 20:09.