# outlet boundary condition

 Register Blogs Members List Search Today's Posts Mark Forums Read

 December 30, 2001, 16:09 outlet boundary condition #1 Arash Guest   Posts: n/a In finite volume SIMPLE method which parameters must be defined for outlet boundary condition? thanks arash

 December 31, 2001, 07:11 Re: outlet boundary condition #2 John Guest   Posts: n/a none unless you have multi-outlets - then you have to specify the proportion of mass flow out from each outlet.

 January 1, 2002, 22:42 Re: outlet boundary condition #3 Thomas P. Abraham Guest   Posts: n/a Hello John, Are you sure about that? I think, for an incompressible flow, we need to specify a constant pressure at the outlet. Thanks, Thomas

 January 2, 2002, 09:54 Re: outlet boundary condition #4 John Guest   Posts: n/a It really depends on what one means by outlet boundary condition: I understand it as a numerical boundary condition where flow and other variable (aside from pressure) changes very little in the streamwise direction, that is dfi/dx=0. Therefore one does not specify anything as the boundary condition will be determined as part of the solution. However if you mean outlet boundary condition as the flow goes out of the computational domain, then you can use many different specification such as pressure boundary.

 January 4, 2002, 00:17 Re: outlet boundary condition #5 STN Guest   Posts: n/a It really depends on flow configuration. Is it steady of unsteady flow? For steady flow, normally, it use dPhi/dx = 0.0 which mean that there is no change along streamwise direction at the outlet. Or for Unsteady flow, it use convective boundary condition, DPhi/Dt = dPhi/dt + Uc*dPhi/dx = 0.0 where Uc is convective velocity with mass conservation. However, in the latter, I do not clear how to implement that equation into source code. Especialy for grid with zero volume on the boundary. Could anyone shed some light on me, please?

 January 4, 2002, 07:02 Re: outlet boundary condition #6 John Guest   Posts: n/a The unsteady form of outlet convective boundary condition is majorly used when LES or DNS is used to prevent pressure wave reflected back into flow domain. Uc is choosen such that the overall mass is conserved and DPHI/Dx can be evaluated from (PHI_outlet-Phi_cell)/DX

 January 4, 2002, 09:47 Re: outlet boundary condition #7 Seb Perron Guest   Posts: n/a Usually, you specify a free exit: the pressure is constant (there is no correction of the pressure at the outlet and it the pressure is usually equal to zero). Furthermore, the derivative of the streamwise velocity is zero ( neumann BC). For incompressible flow you most of the time follow this simple rule: normal velocity imposed (inlet or wall), neumman BC for pressure correction; normal velocity unknown (outlet) pressure must be given. Hence, your problem will always be well posed.

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post cfdfsi Fluent UDF and Scheme Programming 2 December 11, 2015 23:48 natantyt FLUENT 0 September 27, 2010 15:30 Pankaj CFX 9 November 23, 2009 05:05 siamak1424 OpenFOAM 2 August 15, 2009 11:14 CN FLUENT 6 May 22, 2005 09:37

All times are GMT -4. The time now is 17:19.