CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Main CFD Forum

outlet boundary condition

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   December 30, 2001, 16:09
Default outlet boundary condition
  #1
Arash
Guest
 
Posts: n/a
In finite volume SIMPLE method which parameters must be defined for outlet boundary condition? thanks arash
  Reply With Quote

Old   December 31, 2001, 07:11
Default Re: outlet boundary condition
  #2
John
Guest
 
Posts: n/a
none unless you have multi-outlets - then you have to specify the proportion of mass flow out from each outlet.
  Reply With Quote

Old   January 1, 2002, 22:42
Default Re: outlet boundary condition
  #3
Thomas P. Abraham
Guest
 
Posts: n/a
Hello John,

Are you sure about that? I think, for an incompressible flow, we need to specify a constant pressure at the outlet.

Thanks,

Thomas
  Reply With Quote

Old   January 2, 2002, 09:54
Default Re: outlet boundary condition
  #4
John
Guest
 
Posts: n/a
It really depends on what one means by outlet boundary condition: I understand it as a numerical boundary condition where flow and other variable (aside from pressure) changes very little in the streamwise direction, that is dfi/dx=0. Therefore one does not specify anything as the boundary condition will be determined as part of the solution. However if you mean outlet boundary condition as the flow goes out of the computational domain, then you can use many different specification such as pressure boundary.
  Reply With Quote

Old   January 4, 2002, 00:17
Default Re: outlet boundary condition
  #5
STN
Guest
 
Posts: n/a
It really depends on flow configuration. Is it steady of unsteady flow? For steady flow, normally, it use dPhi/dx = 0.0 which mean that there is no change along streamwise direction at the outlet.

Or for Unsteady flow, it use convective boundary condition, DPhi/Dt = dPhi/dt + Uc*dPhi/dx = 0.0 where Uc is convective velocity with mass conservation.

However, in the latter, I do not clear how to implement that equation into source code. Especialy for grid with zero volume on the boundary. Could anyone shed some light on me, please?
  Reply With Quote

Old   January 4, 2002, 07:02
Default Re: outlet boundary condition
  #6
John
Guest
 
Posts: n/a
The unsteady form of outlet convective boundary condition is majorly used when LES or DNS is used to prevent pressure wave reflected back into flow domain. Uc is choosen such that the overall mass is conserved and DPHI/Dx can be evaluated from (PHI_outlet-Phi_cell)/DX
  Reply With Quote

Old   January 4, 2002, 09:47
Default Re: outlet boundary condition
  #7
Seb Perron
Guest
 
Posts: n/a
Usually, you specify a free exit: the pressure is constant (there is no correction of the pressure at the outlet and it the pressure is usually equal to zero). Furthermore, the derivative of the streamwise velocity is zero ( neumann BC). For incompressible flow you most of the time follow this simple rule:

normal velocity imposed (inlet or wall), neumman BC for pressure correction;

normal velocity unknown (outlet) pressure must be given.

Hence, your problem will always be well posed.
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Outlet Pressure-flow coupled boundary condition (Windkessel) cfdfsi Fluent UDF and Scheme Programming 1 October 12, 2011 10:01
Boundary Condition outlet natantyt FLUENT 0 September 27, 2010 15:30
RPM in Wind Turbine Pankaj CFX 9 November 23, 2009 05:05
inlet and outlet boundary condition for turbomachinery solution siamak1424 OpenFOAM 2 August 15, 2009 11:14
Outlet boundary condition CN FLUENT 6 May 22, 2005 09:37


All times are GMT -4. The time now is 09:07.