CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > STAR-CCM+

Drag Predication Problem for free-surface flow using STAR-CCM+

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   January 10, 2011, 15:33
Default Drag Predication Problem for free-surface flow using STAR-CCM+
  #1
Member
 
Naimish Harpal (MS Aerospace Engr)
Join Date: Jul 2009
Location: Long Beach, CA
Posts: 50
Rep Power: 8
naimishharpal is on a distinguished road
Dear all,
I am currently doing test-validation cases for free-surface flow [VOF method] over a Wigley Hull geometry using STAR-CCM+ v5.06.

For a contant Froude Nb. = 0.267 case, the solution is converged, and also the maximum and area-averaged CFL numbers on free-surface look great too (below 0.1 and 4 respectively). The total drag force is also coming in a good range of agreement. The water-line at hull surface matches with experimental data.

The only issue is that even after t = 35s of physical simulation time (and time-step of 0.01s), the drag forces keep oscillating with \pm1 N range for presumed steady-solution. Even though drag force range is small value, when calculating drag coefficient and try to compare with experimental data; the difference is huge about 10-15% error.

P.S. I used reliazable K-Epsilon two-layer turbulence model [with required sufficient viscous boundary layer mesh resolution (y+ = 1) on the wigley hull surfaces].

Please advise on how to increase the accuracy at calculating drag force.

Thanks.
naimishharpal is offline   Reply With Quote

Old   January 11, 2011, 02:24
Default
  #2
Senior Member
 
Ping
Join Date: Mar 2009
Posts: 223
Rep Power: 9
ping is on a distinguished road
it is very common for vof marine calculations to oscillate even after long run times - depends on many factors like DOFs freed, MoI, wave interactions and reflections etc etc. Ensure you have suffucient inner iterations, and dt is small enough. Then if the variations seem logical, simple average the drag results - eg use field mean monitor with a sliding window (or export drag monitor to Excel etc and average there).
ping is offline   Reply With Quote

Old   January 11, 2011, 03:36
Default
  #3
Member
 
Naimish Harpal (MS Aerospace Engr)
Join Date: Jul 2009
Location: Long Beach, CA
Posts: 50
Rep Power: 8
naimishharpal is on a distinguished road
I agree with your concern, but my simulations are with 0-DOF and calm incoming water (no waves). The time-step is 0.01s with 25 inner iterations.
naimishharpal is offline   Reply With Quote

Old   January 12, 2011, 16:10
Default Drag Measurement
  #4
New Member
 
Matt Knapp
Join Date: Jan 2011
Location: Redmond Wa
Posts: 3
Rep Power: 6
mattknapp is on a distinguished road
Since this validation case seems to be mostly working for you, I thought I'd add a question. For measuring drag, are you doing anything more than setting up a force (and/or coefficient ) monitor for the vehicle body in the direction of current? (Fx typically)

I'm primarily an aero guy, but just started running some VOF simulations for a (just barely) submerged body at increasing distance from the free surface. The goal was to look at wave drag as a function of depth, and we were expecting to see some increase as the vehicle approached the surface and expecting an exponential relationship. The Froude number is 0.4 so there should be a lot of wave drag. We get pretty reasonably looking surface perturbations, which do increase significantly as the vehicle approaches the surface, but the drag is absolutely steady, and varies by only small fractions of a percent between depths, with no trend to depth at all.
thanks
M<
mattknapp is offline   Reply With Quote

Old   January 12, 2011, 21:41
Default
  #5
Senior Member
 
sail's Avatar
 
Vieri Abolaffio
Join Date: Jul 2010
Location: Always on the move.
Posts: 308
Rep Power: 7
sail is on a distinguished road
probably it is not the cause, but...

to perform the drag evaluation are you considering only the water phase's drag or also the air one?

@ matt:

you shoud not expect grat variations because the wave train you obtain is generated by the pressure field wich encounter the free surface.
sail is offline   Reply With Quote

Old   January 12, 2011, 21:56
Default
  #6
New Member
 
Matt Knapp
Join Date: Jan 2011
Location: Redmond Wa
Posts: 3
Rep Power: 6
mattknapp is on a distinguished road
I'm just creating a force report (Pressure + Shear) on the submersible body. Is there a better way to capture the physics?
mattknapp is offline   Reply With Quote

Old   January 15, 2011, 09:57
Default
  #7
Senior Member
 
Join Date: Oct 2009
Location: Germany
Posts: 637
Rep Power: 12
abdul099 is on a distinguished road
Who says, the oscillation is not physical? There are not very much real steady flows. Usually you can see osciallations due to vortex shedding in a lot of applications, and very often the oscillations are too big to neglect. O.k., 10 to 15% is a lot, but I wouldn't be too worried about the oscillations itself.

When you put a body in a wind tunnel (or a hull in a water channel) to measure the drag, your measurement system will usually average the values over time and it seems, there would be a steady flow.
Just consider a karman vortex street behind a cylinder, like a chimney, an antenna on a car roof or a house.
abdul099 is offline   Reply With Quote

Old   November 4, 2011, 11:44
Default Got something very similar
  #8
New Member
 
Eran
Join Date: Sep 2011
Location: Massachusetts
Posts: 11
Rep Power: 5
Surfboy is on a distinguished road
i am running a tow tank equivalent simulation.
hull fixed.
speed - 2.1m/s length of hull about 6m.

size of water domain - X=16m Y=9m

for the shear force i get the exact tow tank result. it looks very stable.

for the pressure force i get an oscillating force between 10 and 3, which gives the mean value of 6.5N which is not bad compared to the tow tank result.

i have a "pressure outlet" condition on the outlet wall.

is the oscillation a result of reflected long wave?

how can i solve it? (will the wave decay if i make a gradual enlargement in the width of the domain far behind the hull?)

thanks.
Surfboy is offline   Reply With Quote

Old   November 4, 2011, 12:32
Default
  #9
Member
 
Naimish Harpal (MS Aerospace Engr)
Join Date: Jul 2009
Location: Long Beach, CA
Posts: 50
Rep Power: 8
naimishharpal is on a distinguished road
Hi Surfboy,
Q: Is the oscillation a result of reflected long wave? how can i solve it? (will the wave decay if i make a gradual enlargement in the width of the domain far behind the hull?)
A: Yes. Bigger domain helps this problem. Also, Once you get started converged solution, you may increase under-relaxation little bit and run faster for few more iterations to get low residual results. From this exercise, I found drag forces to be stable.
naimishharpal is offline   Reply With Quote

Old   November 6, 2011, 04:38
Default
  #10
Senior Member
 
Ping
Join Date: Mar 2009
Posts: 223
Rep Power: 9
ping is on a distinguished road
the pressure drag fluctuation seems way too high (assuming you have run for quite a long time), especially since the hull is fixed. a larger domain might help as will dampening the waves at the boundaries - use the boundary wave dampening feature and maybe coarsen the mesh up (slowly since rapid size changes can also cause reflection) towards the boundaries (by not the inlet).
ping is offline   Reply With Quote

Old   February 14, 2012, 10:22
Default train moving in tunnel help
  #11
Member
 
Join Date: Jan 2012
Posts: 58
Rep Power: 5
sheikh nasir is on a distinguished road
hello
i am working on train moving in tunnel. i am getting floating error:invalid number. can any one help me. my email is sheikhnasir39@gmail.com
plz help me
thanks

sheikh nasir is offline   Reply With Quote

Old   February 14, 2012, 12:32
Default
  #12
Member
 
Join Date: Feb 2011
Location: DE-PB
Posts: 56
Rep Power: 6
willimanili is on a distinguished road
What does your problem has to do with freesurface flow?
Why do you post the same post about thirty times anywhere at the forum?
Do you want me to inform the adminstrator about your spaming?!

As you can see, nobody can help you. And do you know why?!
Because your post is so meaningless that nobody could ever help you. So please, be more specific or leave it and especially dont spam the forum, maybe then anybody will help you.
willimanili is offline   Reply With Quote

Reply

Tags
drag force, vof, wigley hull

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Error : Self intersecting surface mesh, computing intersections & Error : Impossible velan Open Source Meshers: Gmsh, Netgen, CGNS, ... 0 June 29, 2009 00:48
mass flow rate on the Iso-clip surface & interior Sunil Gupta FLUENT 0 April 22, 2008 09:29
Multiphase flow problem icedou FLUENT 6 July 10, 2005 02:52
gravitational force for free surface flow Jongtae Kim Main CFD Forum 1 July 2, 2000 11:57
fluid flow fundas ram Main CFD Forum 5 June 17, 2000 21:31


All times are GMT -4. The time now is 04:30.