CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

What is "mesh quality" in ICEM-CFD

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree3Likes
  • 1 Post By PSYMN
  • 2 Post By PSYMN

Reply
 
LinkBack Thread Tools Display Modes
Old   July 27, 2009, 05:27
Default What is "mesh quality" in ICEM-CFD
  #1
New Member
 
Vijesh Joshi
Join Date: Mar 2009
Posts: 10
Rep Power: 8
vijeshjoshi23 is on a distinguished road
Hi friends,
What are all the things we have to check to confirm that the mesh generated does not contain bad elements. Even if some bad elements are unavoidable what is the limiting number for bad elements? At present, I m checking skewness only. Plz reply...

Thank you...
vijeshjoshi23 is offline   Reply With Quote

Old   July 27, 2009, 07:23
Default
  #2
New Member
 
Ben
Join Date: Jun 2009
Location: Tasmania
Posts: 16
Rep Power: 8
brissyben is on a distinguished road
Need to ensure volumes are greater than 0, and determinats are greater than 0. your mesh will not run if you have -ve volumes or determinants.

Look at angles as well, should be above 18 but i think most solvers can handle above 9 - look in the help manual it tells you all about these
brissyben is offline   Reply With Quote

Old   July 28, 2009, 09:40
Default Depends on your solver...
  #3
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 36
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
This is definitely a solver based question… Look at your solver manual (or ask on that portion of the CFD-Online site) and find out what the requirements are. Some solvers are fine with 179 degree internal angles, others are very sensitive to angle quality. Some solvers are sensitive to pyramids but don’t mind really skewed prisms instead…

One thing to keep in mind is that most solvers are going to sneak in a factor of safety, so you may read that they need an internal angle of at least 18 degrees. In reality, 9 degrees would probably be fine and you may even be able to get away with >0 degrees. By publishing higher requirements, the solver tech support can blame any convergence issues on the mesh ;^).

I check a few usual suspects. ICEM CFD “Quality” (circumsphere ratio) should usually be above 0.1 for tetras and hexas, and above 0.01 for prisms. Determinant (1/jacobian) should be greater than 0.1. Angle should be greater than 9 or 18 degrees. Often I will have a few cells of lower quality. As long as they are above zero and not in a critical region, I may still try to run the model and see if it will converge.
metmet likes this.
PSYMN is offline   Reply With Quote

Old   July 28, 2009, 09:42
Default 2 quick notes.
  #4
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 36
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
oh yea, two more quick thoughts about ICEM CFD quality...

First, prism quality in ICEM CFD is calculated harshly. They divide the prism into 3 tetras and report the quality of the worst one (circumsphere ratio) as the prism quality. This makes the ICEM CFD prisms look much worse than they are, so keep that in mind when comparing qualities between softwares.

Second, at 12.0, ICEM CFD added a TGrid Skew metric to make it easier for Fluent users to check their quality against the Fluent manual. At 12.1, ICEM CFD added an Expansion rate metric for CFX users. (12.1 is not due out until the end of 2009, but the check is already in the Beta version.)
dhananjay1287 and shereez234 like this.
PSYMN is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Help for ICEM CFD - urgent Tuks CFX 3 February 8, 2010 04:32
ICEM CFD to CFX geometry and mesh Luca CFX 6 February 4, 2010 17:31
Boddy fitted Hexcore Mesh in ICEM Cfd Mitch CFX 0 December 29, 2008 07:07
How about ICEM CFD M.Gao Main CFD Forum 1 November 15, 1999 05:15
Which is better to develop in-house CFD code or to buy a available CFD package. Tareq Al-shaalan Main CFD Forum 10 June 12, 1999 23:27


All times are GMT -4. The time now is 06:11.