CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] Blocking of 2 cylinders

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   April 12, 2011, 07:13
Default Blocking of 2 cylinders
  #1
New Member
 
Frank Weise
Join Date: Mar 2009
Location: Germany
Posts: 27
Rep Power: 8
FrankW is on a distinguished road
Hi,
i will mesh 2 cylinders with blocking. The problem is the cylinders have a common intersection point. See the pictures in the attachment.
How should i change my blocking to get the right mesh?

Thanks
Frank
Attached Images
File Type: jpg Bild1.jpg (89.5 KB, 85 views)
File Type: jpg Bild2.jpg (88.8 KB, 74 views)
FrankW is offline   Reply With Quote

Old   April 12, 2011, 07:19
Default
  #2
Senior Member
 
AB
Join Date: Sep 2009
Location: France
Posts: 323
Rep Power: 12
BrolY will become famous soon enough
I guess you created an O-grid for your 1st (big) cylinder.
Then split your O-grid around the curevs of your 2nd (small) cylinder.
Then, do an O-grid for your 2nd (small) cylinder.
BrolY is offline   Reply With Quote

Old   April 12, 2011, 10:41
Default
  #3
New Member
 
Frank Weise
Join Date: Mar 2009
Location: Germany
Posts: 27
Rep Power: 8
FrankW is on a distinguished road
Hi BrolY,
thanks for the fast reply. Can you explain how i split the o-grid around the curves of the 2nd small cylinder. In the attachmet i've finished step 1 at a test cylinder.

Thanks

Edit: I 've attached the geometric files
Attached Images
File Type: jpg Bild3.jpg (92.0 KB, 58 views)
Attached Files
File Type: zip Test Netz.zip (11.5 KB, 16 views)

Last edited by FrankW; April 12, 2011 at 11:08.
FrankW is offline   Reply With Quote

Old   April 13, 2011, 08:39
Default
  #4
Senior Member
 
AB
Join Date: Sep 2009
Location: France
Posts: 323
Rep Power: 12
BrolY will become famous soon enough
I found 2 solutions, but maybe other users may have other ideas:

1) Create 2 meshes, and do a conformal merge of the 2 meshes.
2) in your blocking, create another split along the 2nd (small) cylinder. Then merge the two nodes at the intersection point. Delete the block along your small cylinder (the one created by the previous split), and associate. At the end, the quality of the mesh will be bad ...

I'll try to figure out another way to have a good mes quality without creating 2 meshes.
Good luck !
BrolY is offline   Reply With Quote

Old   April 13, 2011, 12:34
Default Solution
  #5
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 36
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Hey Frank,

The difficulty here is because the smaller pipe is all the way at the end of the larger pipe. It can be done but it is a minor hassle...

Is this how you need the geometry to be? Do you plan to extend the large pipe anyway or does this represent the end wall of the pipe? If it is an end wall, does the actual model meet perfectly like this or does the larger pipe actually extend a little beyond the small pipe? The more complex the model, the more I would suggest you push these questions.

On the other hand, this is a pretty simple model. So lets just sort it out as it is. We will need to propagate the wedge shape back thru the larger pipe... Can you handle wedges (easiest solution) or does your solver require pure hexa? (Or maybe I should just ask; what is your solver?) I will start with wedges. The pure hexa solution involves replacing the wedge with a Yblock...

The basic approach should be to pretend there is a little lip at the end (I actually copied a point out by 0.1 to make it easier to pretend). You will need to split to capture both sides of the little pipe. Ogrid the large pipe as you did, then also Ogrid the smaller pipe (Select the pipe block and the block just inside the large pipe. Also select the face on the outer end of the small pipe and the symmetry planes.) Then come back and merge away the small edge and its parallel pairs (4 total pairs) back thru the model. This will collapse it into a wedge that goes back thru the model.

Anyway, it only takes 2 minutes (less time than to type this email actually), so here it is.

Run the replay file with the "always update" option to see my steps.

Best regards.
Attached Images
File Type: jpg FrankW_01.jpg (79.7 KB, 71 views)
File Type: jpg FrankW_02.jpg (66.8 KB, 60 views)
File Type: jpg FrankW_03.jpg (69.8 KB, 61 views)
Attached Files
File Type: zip FrankWeise.zip (7.8 KB, 25 views)
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   April 14, 2011, 10:49
Default
  #6
New Member
 
Frank Weise
Join Date: Mar 2009
Location: Germany
Posts: 27
Rep Power: 8
FrankW is on a distinguished road
Hi PSYMN,

thanks for your explanations. It helps me fine. The original geometry has similar dimensions and is more complicated. In the attachment are the files. The inlay called MG_Rahmen.. is a porus structure. This part was easily to mesh (MG_Rahmen.zip). My problem is the meshing of the rest of the fluidic part. In the past i used only Anys WB meshing and i'am so not confirm with ICEM. Because the small structures i think i can generate better meshs with ICEM with less elements.
The real stuctures has the same dimensions. And i need an adequate model to compare our Oxygen measurements with the theoretic model. Our Flowrate is moderate, we have a real laminar flow RE<10.

Best regards.
Attached Files
File Type: zip Dfz_Mod4_1.zip (89.3 KB, 13 views)
File Type: zip MG_Rahmen.zip (62.4 KB, 12 views)
FrankW is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] o grid blocking strategy? icemaniac178 ANSYS Meshing & Geometry 14 March 20, 2013 00:18
[ICEM] Blocking and Symmetry BrolY ANSYS Meshing & Geometry 32 August 24, 2012 03:13
[ICEM] Blocking strategy BrolY ANSYS Meshing & Geometry 0 July 22, 2010 04:46
[ICEM] generating tetra mesh on various cylinders at the same time karananand ANSYS Meshing & Geometry 2 July 9, 2010 16:34
Mesh is created in blocking Severin CFX 3 September 18, 2007 09:02


All times are GMT -4. The time now is 04:55.