CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Advice on open channel flow for an water intake chamber

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   August 21, 2014, 05:05
Default Advice on open channel flow for an water intake chamber
  #1
New Member
 
Jonny Cox
Join Date: Aug 2014
Posts: 6
Rep Power: 2
jcox675 is on a distinguished road
Hello, I am new to CFX and need advice on how to start/continue a simulation to do with open channel flow.
In the attached file is the setup showing what I would like. There will be an input and output of water with the free surface in atmospheric conditions.
I need to find the velocity of the water entering the chamber.

What boundary conditions and general settings would you suggest?
Which analysis type would be best?

Sorry for the really simple questions and thanks for the help!

Jonny
Attached Images
File Type: jpg CFX Setup.jpg (86.3 KB, 19 views)
jcox675 is offline   Reply With Quote

Old   August 21, 2014, 05:52
Default
  #2
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,796
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
What do you know about the flow? What are the fluids?
ghorrocks is offline   Reply With Quote

Old   August 21, 2014, 08:41
Default
  #3
New Member
 
Jonny Cox
Join Date: Aug 2014
Posts: 6
Rep Power: 2
jcox675 is on a distinguished road
The fluids are water and air. The input and output flow is the same (mass flow rate 300). Thanks a lot.

Jonny
jcox675 is offline   Reply With Quote

Old   August 21, 2014, 20:37
Default
  #4
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,796
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
There needs to be something to drive the flow. Is the channel sloped? Pressure gradient?

What is open to the atmosphere? Does anything control the water level?
ghorrocks is offline   Reply With Quote

Old   August 22, 2014, 04:21
Default
  #5
New Member
 
Jonny Cox
Join Date: Aug 2014
Posts: 6
Rep Power: 2
jcox675 is on a distinguished road
The area open to atmosphere is the top face of the channel. In reality water comes from that open face and the channel is sloped, but I want to make as simple a model as possible. The water would collect in the channel and eventually due to gravity drop into the chamber. I know this won't work as I have modeled the water entering from the side face however. I just want to find out the behaviour of the water as it goes through the channel, into the chamber and out the pipe.
A valve further down the pipe controls how much water goes through the system, but i thought it would be okay just to monitor the flow in and the flow out.
What would you suggest?
Thanks again
jcox675 is offline   Reply With Quote

Old   August 22, 2014, 06:53
Default
  #6
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,796
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
It sounds like before you start anything you have to sort out exactly what your boundary conditions are.

You say water flows into it - you have to define this. Do you know the flow rate? If so then this is easy to define the inlet boundary.

You say the outlet is controlled by a valve. How is the valve controlled? Is it just at a fixed opening point to throttle the flow? In that case you should model the outlet as the valve discharge curve. Or is it controlled somehow - in that case how?
ghorrocks is offline   Reply With Quote

Old   August 22, 2014, 08:56
Default
  #7
New Member
 
Jonny Cox
Join Date: Aug 2014
Posts: 6
Rep Power: 2
jcox675 is on a distinguished road
So I have played around with some tutorials and think I would be able to do it apart from knowing what boundaries to use!

I know the flow rate going in which will be straight forward. The outlet valve will have the same flow going out as we are not modelling the valve. Trying to get a basic flow analysis done before we add more complex parts to it!

The main problem was that I wasn't sure about was the top face opening boundary conditions and the general settings for water in atmospheric conditions.
Cheers
jcox675 is offline   Reply With Quote

Old   August 22, 2014, 09:28
Default
  #8
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,796
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
You need to think harder about the boundary conditions. OK, so you know the flow in. But to then use the same flow as an outlet condition would be badly posed. Have a think about it - what controls the water level if the outlet flow rate is set as a constant? It means your fluid level is not controlled and this run will not converge.

The thing which probably defines your outlet flow rate is the static head applied to the outlet valve. The static head (which is your fluid level) will adjust until the flow rate in the valve matches the flow rate in. Now your fluid level is coupled to the outlet flow in a well-posed manner.

So yes, the top boundary is just an opening with atmospheric pressure. But you need to think more carefully about your outlet condition if you want this simulation to work.
ghorrocks is offline   Reply With Quote

Old   August 26, 2014, 06:27
Default
  #9
New Member
 
Jonny Cox
Join Date: Aug 2014
Posts: 6
Rep Power: 2
jcox675 is on a distinguished road
Yes that makes sense. How would I set the outlet condition to be dependent on the static head? Would it be similar to the equations found in tutorial 7? how would they compare? Thank you for bearing through this!
jcox675 is offline   Reply With Quote

Old   August 26, 2014, 22:56
Default
  #10
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,796
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
If the outlet valve is fixed then it will have a pressure drop versus flow rate curve. Then apply this curve.

If the valve moves or is under active control then you have to model the movement or control.
ghorrocks is offline   Reply With Quote

Old   September 4, 2014, 05:17
Default
  #11
New Member
 
Jonny Cox
Join Date: Aug 2014
Posts: 6
Rep Power: 2
jcox675 is on a distinguished road
I have tried to search how to apply this curve but have been unsuccessful. How would you apply it?
jcox675 is offline   Reply With Quote

Old   September 4, 2014, 07:28
Default
  #12
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,796
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
There are two options:

1) Set the outlet to be a massflow outlet. Calculate the areaAve(p)@Outlet, and use a lookup table on the massflow versus p for the valve to set the massflow.
2) Set the outlet to be a pressure outlet. Calculate the massflow()@Outlet, and use a lookup table on the massflow versus p for the valve to set the pressure.

They are just two different ways of doing the same thing. But I suspect you will find the first is more numerically stable than the second.
ghorrocks is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Question on the boundary condition for open channel flow, please help! ripperjack OpenFOAM Running, Solving & CFD 0 September 13, 2013 11:44
Gravitational water flow in closed channel. Szymon85 CFX 7 September 3, 2013 16:28
Open Channel Flow Boundary Conditions TWaung STAR-CCM+ 2 October 7, 2011 00:37
Open Channel Flow forsumit FLUENT 0 October 1, 2009 02:01
VOF modelling open channel river flow Matthew Roberts FLUENT 6 July 31, 2009 12:52


All times are GMT -4. The time now is 05:27.