CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

fully develpoed flow in inlet

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   December 15, 2000, 00:32
Default fully develpoed flow in inlet
  #1
Kim, Hongju
Guest
 
Posts: n/a
Hi, CFX users

I am trying to set boundary conditions of 'fully developed flow' at pipe inlet without preliminary calculation. How can I set the BC's. Thanks.
  Reply With Quote

Old   December 15, 2000, 04:25
Default Re: fully develpoed flow in inlet
  #2
Fabian
Guest
 
Posts: n/a
Hi,

you can set a mass flow boundary condition at the inlet with negative mass flux. The procedure is explained in the CFX4.x solver manual.
  Reply With Quote

Old   December 18, 2000, 05:02
Default Re: fully develpoed flow in inlet
  #3
Kim, Hongju
Guest
 
Posts: n/a
Thank you for your response. But, I still could not set a mass flow boundary condition at the inlet. I read the CFX4.2 solver manual carefully and tried to set a flow boundary condition with very simple one block pipe. Then I got a error message. I am a CFX beginner. So I do not know what is my mistake. Would you please explain the my mistake ?

>>CFX4
:>OPTIONS

THREE DIMENSIONS

BODY FITTED GRID

CARTESIAN COORDINATES

TURBULENT FLOW

ISOTHERMAL FLOW

INCOMPRESSIBLE FLOW

STEADY STATE
:>MODEL TOPOLOGY
:>CREATE PATCH

PATCH NAME 'ENTRANCE'

BLOCK NAME 'SOLID 1'

PATCH TYPE 'MASS FLOW BOUNDARY'

LOW K
:>CREATE PATCH

PATCH NAME 'OUTLET'

BLOCK NAME 'SOLID 1'

PATCH TYPE 'PRESSURE BOUNDARY'

HIGH K
:>MODEL DATA
:>PHYSICAL PROPERTIES

>>FLUID PARAMETERS

VISCOSITY 1.0000E-03

DENSITY 9.9800E+02
:>SOLVER DATA
:>PROGRAM CONTROL

MAXIMUM NUMBER OF ITERATIONS 200

MASS SOURCE TOLERANCE 1.0000E-06
:>MODEL BOUNDARY CONDITIONS
:>MASS FLOW BOUNDARIES

>>FLUX

MASS FLOW SPECIFIED

FLUXES -1.000000E+01
:>STOP

CFX-4.2 started on Mon Dec 18 17:32:03 KST 2000

This job was run on : kngr The command line was: /CFX4.2/bin/runsolve4 -rel 4.2 -dir /TH2/th/hjukim/CFX4/o ri/con/geo/F1/tmp1/.cfx4_tmpdir -enviro 08 -c m08.fc -geom m01.geo -dynam

>>CFX4

>>OPTIONS

THREE DIMENSIONS

BODY FITTED GRID

CARTESIAN COORDINATES

TURBULENT FLOW

ISOTHERMAL FLOW

INCOMPRESSIBLE FLOW

STEADY STATE
:>MODEL TOPOLOGY

>>CREATE PATCH

PATCH NAME 'ENTRANCE'

BLOCK NAME 'SOLID 1'

PATCH TYPE 'MASS FLOW BOUNDARY'

LOW K

>>CREATE PATCH

PATCH NAME 'OUTLET'

BLOCK NAME 'SOLID 1'

PATCH TYPE 'PRESSURE BOUNDARY'

HIGH K
:>MODEL DATA

>>PHYSICAL PROPERTIES

>>FLUID PARAMETERS

VISCOSITY 1.0000E-03

DENSITY 9.9800E+02
:>SOLVER DATA

>>PROGRAM CONTROL

MAXIMUM NUMBER OF ITERATIONS 200

MASS SOURCE TOLERANCE 1.0000E-06
:>MODEL BOUNDARY CONDITIONS

PERMANENT WORKSPACE ALLOCATED

TYPE TOTAL SET TOTAL USED REAL 2716160 814827 INTEGER 1358080 484175 CHARACTER 1049 371

>>MASS FLOW BOUNDARIES

>>FLUX

LINEAR SOLVER - BLOCK DEPENDENCY INFORMATION:

PERCENTAGE OF WELL ORDERED BLOCKS 100.0000 ORDERING USED

1

####> ERROR. THE >>STOP COMMAND HAS NOT BEEN READ THE COMMANDS MAY BE IN THE WRONG ORDER OR INCORRECTLY TYPED PLEASE CORRECT AND RE-SUBMIT THE JOB THE CFX-4 SOLVER HAS BEEN STOPPED BY SUBROUTINE OUTOPT

CFX-4.2 finished on Mon Dec 18 17:32:17 KST 2000

  Reply With Quote

Old   December 18, 2000, 06:07
Default Re: fully develpoed flow in inlet
  #4
Fabian
Guest
 
Posts: n/a
Hi,

if you are using the 4.2 version, first of all there is a bug, or a spelling mistake in the manual whatever you want. The keyword is "FLUXES" and not "FLUX" (this was fixed in the 4.3 version):
:>MASS FLOW BOUNDARIES

>>FLUXES

MASS FLOW SPECIFIED

FLUXES -1.0E+1 1.0E+1

Secondly you have to define group numbers for the inlet and outlet:
:>MODEL TOPOLOGY
:>MODIFY PATCH

OLD PATCH NAME 'ENTRANCE'

NEW PATCH NAME 'ENTRANCE'

NEW PATCH TYPE 'MASS FLOW BOUNDARY'

NEW PATCH GROUP NUMBER 1

OLD PATCH NAME 'OUTLET'

NEW PATCH NAME 'OUTLET'

NEW PATCH TYPE 'MASS FLOW BOUNDARY'

NEW PATCH GROUP NUMBER 2

In the boundary condition set up the first group refers to -1.0 , the second to 1.0 and so on if you have more.

Hope this helps Fabian
  Reply With Quote

Old   December 19, 2000, 06:25
Default Re: fully develpoed flow in inlet
  #5
Marat Hoshim
Guest
 
Posts: n/a
I'm mot quite sure anymore but it is possible to have only a MASS FLOW BOUNDARY and a PRESSURE BOUNDARY ? This combination looks a little strange to me.

Marat
  Reply With Quote

Old   December 20, 2000, 07:04
Default Re: fully develpoed flow in inlet
  #6
hong
Guest
 
Posts: n/a
For this question,if the inlet is a mass flux, the converenge is difficult.this is also not the mean of :fully developed flow inlet.; so it may be good to use inlet BC. then you only need keep the momentum as a constant. that is Ok
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Mass flow inlet and pressure outlet issue nikhil FLUENT 5 December 11, 2013 13:30
Species mass flow inlet lorenz FLUENT 3 March 15, 2012 08:26
Wake induced inlet flow sherifkadry CFX 9 August 16, 2011 17:26
Flow Reversal at the inlet salihovic CFX 3 July 15, 2010 10:50
modelling slug flow with pressure inlet Azman FLUENT 0 May 29, 2006 06:45


All times are GMT -4. The time now is 17:11.