|
[Sponsors] |
January 12, 2007, 04:48 |
Laminar non-premixed flame
|
#1 |
Guest
Posts: n/a
|
Hello,
I have tough time here to simulate a laminar non-premixed methane-air flame. I use the Finite Rate Chemistry model for this purpose.I find that it always over-predicts the temperature giving values only between 5000 - 6000 K. I am initializing the domain temperature to about 1200 K. Can anyone throw light on where I am making a mistake? The same mesh with increased flow rates and on usage of Eddy Dissipation model gives satisfactory results Regards, Paul |
|
January 14, 2007, 07:23 |
Re: Laminar non-premixed flame
|
#2 |
Guest
Posts: n/a
|
have a look into FAQ section here: http://www.cfd-online.com/Wiki/Ansys_FAQ
there's an answer. have a good fun matej |
|
January 15, 2007, 00:14 |
Re: Laminar non-premixed flame
|
#3 |
Guest
Posts: n/a
|
Hi Matej,
I am using CFX 10.0. Does the "stiff chemistry = t" option exist in this version? Atleast it doesnt appear in the GUI(Create>Expert Objects>Expert Parameters) which has some similar options. Even typing "stiff chemsitry" in the CFX-Pre Help doesnt throw any results. But still i tried some thing.I went to Tools>Command Editor, copied these commands EXPERT PARAMETERS: stiff chemistry = t END Then I clicked on Process, saved the Pre file and started the run. But i got the following error: "Error: Sub-object 'EXPERT PARAMETERS' is not allowed in /" Any suggestions? Regards, Paul. |
|
January 16, 2007, 00:21 |
Re: Laminar non-premixed flame
|
#4 |
Guest
Posts: n/a
|
Hi Matej, Even i tried doing what Paul did, but with no effect It would be nice if you tell us how to do that in detail
bye, Husain |
|
January 18, 2007, 06:50 |
Re: Laminar non-premixed flame
|
#5 |
Guest
Posts: n/a
|
Hi,
OK, you will not find this in any help file in CFX, it is somehow not documented publicly. if you would have a look in your *.def file in text file, which you can do with a cfx5cmds commands (I do not know how it works in windows, sorry) you would see, that the definition file is structured. Every commands has its unique place, which in case of EXPERT PARAMETER is under the FLOW tree. If you're unsure how to do it, do it with a "cfx5cmds -edit -def *.def" command and add the EXPERT SECTION as described in the manual. After you create the expert section, you may check it in the text file how and where it is written and you may add things like 'stiff chemistry = t' or whatever Cfx wishes to swallow. hope this helps, have fun matej |
|
January 18, 2007, 23:28 |
Re: Laminar non-premixed flame
|
#6 |
Guest
Posts: n/a
|
Thanks a lot Matej,
It really works. The temperatures now have dripped to 2000 K . I couldnt exactly do what you said because I am more familiar with GUI/Windows usage. I did the same thing using GUI. I am really surprised why such a crucial thing has not been documented. For those of you who are troubled by high combustion temperatures by using Finite Rate Chemistry Model, here is the fix in CFX 10.0 1. In the Solver Manager, before you click "Start Run", Go to Tools>Edit definition file. 2. Click Add Parameter if you already have an Expert Parameter Section (otherwise create one) 3. The option "stiff chemistry" is not available by default. Just type in the box "stiff chemistry" and assign a value "t". Save the file and exit. 4. Start the run. Thanks once again Matej Regards, Paul |
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Premixed laminar flame | Burn | OpenFOAM | 7 | August 4, 2009 20:26 |
premixed laminar flame | JCRC | FLUENT | 2 | July 25, 2006 05:33 |
laminar premixed flame | Paul Lee | CFX | 1 | September 14, 2005 06:37 |
Simulating laminar premixed flame | Subhash | FLUENT | 0 | August 17, 2004 00:46 |
steady/unsteady better to laminar premixed flame? | Harry Qiu | FLUENT | 0 | March 27, 2001 02:52 |