CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Pressure wave pattern over body in steadystate?

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 15, 2008, 12:07
Default Pressure wave pattern over body in steadystate?
  #1
Chebeba
Guest
 
Posts: n/a
I am trying to get a good reference solution for an underwater bulb.

My reference model is simple: a revolved NACA0012 profile in free water, speed = 5m/s and angle of attack = 0.

I am comparing with expected results derived from Hoerners "Fluid Dynamic Drag" for a fully turbulent solution (in my case the numbers are L=3.94m, d=0.47m, U=5.0m/s, Re=19.7e6 gives Cf=0.0027, Cd=0.072, which gives me the Drag D=157N).

I have worked with the mesh and boundary layer to get low residuals and good Y+. In this process I have achieved reasonable results in terms of the total Drag of the bulb, 142N. A lower result than the reference should be expected due to the perfectly non-rough surface.

BUT here is my problem: I some very weird numerical effect that I don't know the cause of. The pressure on the bulb has a periodic wave overlaid on the expected result. I have not seen this phenomen before, and I am wondering if someone can explain the cause and what to do to fix it:

Here are a couple of images to visualize the result:





The simulation converges in about 55 iterations. All residuals are then below 1e-4 RMS and the drag calculated as force_x()@Bulb has become steady.

I am running CFX/64 v11.0.1 in Double Precision on WinXP/64.

Relevant parts of the input CCL: (Slightly compressed to make the post reasonable length)

--------------------------------------------------------

LIBRARY: MATERIAL: Water TYPE: Option = Steady State DOMAIN: Default Domain, Coord Frame = Coord 0, Domain Type = Fluid, Fluids List = Water, Location = LIVE

BOUNDARY: BULB, Boundary Type = WALL, Location = BULB, BOUNDARY CONDITIONS: WALL INFLUENCE ON FLOW: Option = No Slip

BOUNDARY: Inlet, Boundary Type = INLET, Location = IN, BOUNDARY CONDITIONS: FLOW REGIME: Option = Subsonic MASS AND MOMENTUM: Normal Speed = 5 [m s^-1], Option = Normal Speed, TURBULENCE: Option = Low Intensity and Eddy Viscosity Ratio

BOUNDARY: Outlet, Boundary Type = OUTLET, Location = OUT, BOUNDARY CONDITIONS: FLOW REGIME: Option = Subsonic MASS AND MOMENTUM: Option = Average Static Pressure, Relative Pressure = 0 [Pa], PRESSURE AVERAGING: Option = Average Over Whole Outlet

BOUNDARY: WALL, Location = WALLS, Boundary Type = WALL, BOUNDARY CONDITIONS: WALL INFLUENCE ON FLOW: Option = Free Slip

DOMAIN MODELS: BUOYANCY MODEL: Option = Non Buoyant DOMAIN MOTION: Option = Stationary REFERENCE PRESSURE: Reference Pressure = 1 [atm]

FLUID MODELS: TURBULENCE MODEL: Option = SST, TURBULENT WALL FUNCTIONS: Option = Automatic

INITIALISATION: Option = Automatic INITIAL CONDITIONS: Velocity Type = Cartesian CARTESIAN VELOCITY COMPONENTS: Option = Automatic with Value U = 5 [m s^-1] V = 0 [m s^-1] W = 0 [m s^-1]

EPSILON: Option = Automatic K: Option = Automatic STATIC PRESSURE: Option = Automatic

------------------------------------------------------------------

Mesh Statistics Total Number of Nodes = 1838274 Total Number of Elements = 3119718 Total Number of Tetrahedrons = 1531323 Total Number of Prisms = 144 Total Number of Hexahedrons = 1547228 Total Number of Pyramids = 41023 Total Number of Faces = 41027

  Reply With Quote

Old   March 16, 2008, 03:00
Default Re: Pressure wave pattern over body in steadystate
  #2
Chebeba
Guest
 
Posts: n/a
Oh well, what a complete and utter laugh!

I have been staring at this problem the whole weekend. And now I realize that it was caused by the actual geometry that the surface elements of the bulb was projected onto.

The default ICEM setting for curve and surface approximation was simply to coarse, causing the bulb surface to have edges. Small edges certainly, not even visible unless you looked for them, but still significant for the flow.
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Center of Pressure for an Aero Body Greg Givogue OpenFOAM Post-Processing 15 July 19, 2011 08:38
Problems simulating a pressure wave supercharger Soupasam FLUENT 1 April 12, 2011 10:52
How to find the reflections of the pressure wave in pipe lines RKR Main CFD Forum 0 April 6, 2011 08:08
Help creating a field function to create a sine pressure wave Pleb STAR-CCM+ 2 February 17, 2011 13:16
Hydrostatic pressure in 2-phase flow modeling (long) DS & HB Main CFD Forum 0 January 8, 2000 16:00


All times are GMT -4. The time now is 04:02.