CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Combustion modeling

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   August 25, 2010, 12:11
Default Combustion modeling
  #1
New Member
 
Pavel
Join Date: Aug 2010
Location: St-Petersburg
Posts: 10
Rep Power: 6
SuperPahan is on a distinguished road
Send a message via Skype™ to SuperPahan
I could not take a combustion process with Jet A in combustion chamber then I have a cone for Jet A liquid particles.I have applied a standard reaction of combustion. a cone for Jet A liquid particles, 3 materials. I use Particle traking model, but there is no combustion in result. May be it is because of extinction temperature, but I can't understand what is it.

Thank you for your time. Sorry for my english.( pavlenty11@gmail.com)
SuperPahan is offline   Reply With Quote

Old   August 28, 2010, 02:48
Default
  #2
New Member
 
Alex
Join Date: Mar 2010
Location: Russia
Posts: 19
Rep Power: 7
a.m. is on a distinguished road
Send a message via ICQ to a.m.
1) do you use standart reactions set for the JetA form templates (../CFX/etc/JetA.ccl)? 3 materials is not enough.
2) witch kind of combustion model do you use? For the first time the EDM model will be better.
a.m. is offline   Reply With Quote

Old   September 2, 2010, 13:44
Default
  #3
New Member
 
Pavel
Join Date: Aug 2010
Location: St-Petersburg
Posts: 10
Rep Power: 6
SuperPahan is on a distinguished road
Send a message via Skype™ to SuperPahan
Quote:
Originally Posted by a.m. View Post
1) do you use standart reactions set for the JetA form templates (../CFX/etc/JetA.ccl)? 3 materials is not enough.
2) witch kind of combustion model do you use? For the first time the EDM model will be better.
Yes,I using a standart reactions. I use EDM model too.I was successful when burned Jet A Liquid instead of Jet A. During that time I had my own reaction with Jet A liquid and oxigen. I set a mass fraction to 1 on fuelin boundary.
But I can't get a combustion with evaporation of Jet A liquid.
SuperPahan is offline   Reply With Quote

Old   September 4, 2010, 04:15
Default
  #4
New Member
 
Alex
Join Date: Mar 2010
Location: Russia
Posts: 19
Rep Power: 7
a.m. is on a distinguished road
Send a message via ICQ to a.m.
Did you try to ignite it? Set the domain temperature about 2500K for 10-15 iteration (use run in progress), then set it back.
a.m. is offline   Reply With Quote

Old   September 7, 2010, 13:02
Default
  #5
New Member
 
Pavel
Join Date: Aug 2010
Location: St-Petersburg
Posts: 10
Rep Power: 6
SuperPahan is on a distinguished road
Send a message via Skype™ to SuperPahan
Quote:
Originally Posted by a.m. View Post
Did you try to ignite it? Set the domain temperature about 2500K for 10-15 iteration (use run in progress), then set it back.
I tried to ignit particles. I set temperature 2000K. But it was, I think, only for the first iteration, but I not sure.How can I ignit particles for 10-15 iterations? Can you write me a sequense of operations?Since the 15th iteration Jet A liquid begin to evaporate.But there are no combustion products(CO2, H20).
SuperPahan is offline   Reply With Quote

Old   September 8, 2010, 00:12
Default
  #6
New Member
 
Alex
Join Date: Mar 2010
Location: Russia
Posts: 19
Rep Power: 7
a.m. is on a distinguished road
Send a message via ICQ to a.m.
The simplest way to ignite the particles is to set air temperature at 2000K (in pre), then, after 10-15 iteration (when CO2 and H2O has appeared), run command editor in solver and set air temperature back (usually look for FLOW:Flow Analysis 1 --> DOMAIN: name --> BOUNDARY: AIR INLET --> BOUNDARY CONDITIONS --> HEAT TRANSFER --> Static Temperature). Also you can set energy source in domain, but it is more difficult.
a.m. is offline   Reply With Quote

Old   September 9, 2010, 11:57
Default
  #7
New Member
 
Pavel
Join Date: Aug 2010
Location: St-Petersburg
Posts: 10
Rep Power: 6
SuperPahan is on a distinguished road
Send a message via Skype™ to SuperPahan
Quote:
Originally Posted by a.m. View Post
The simplest way to ignite the particles is to set air temperature at 2000K (in pre), then, after 10-15 iteration (when CO2 and H2O has appeared), run command editor in solver and set air temperature back (usually look for FLOW:Flow Analysis 1 --> DOMAIN: name --> BOUNDARY: AIR INLET --> BOUNDARY CONDITIONS --> HEAT TRANSFER --> Static Temperature). Also you can set energy source in domain, but it is more difficult.
I was successed in combustion! The main problem,I think, was in the option "1-st iteration for particles calculation"(In Solver control-Particle control).I enabled it, set 3(But default is 10). I Also set particle ignition temperature 2500K.I think, combustion may would be take plase without enabling this option but at least after 10 iterations.But I used to stop calculation, thinking that there is no combustion, after 4 iterations.Now I will be try to do a combustion to ingect particles by hollow cone.
SuperPahan is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
combustion modeling help Krish Main CFD Forum 2 November 3, 2008 16:43
question about modeling combustion xinhui zhang FLUENT 1 December 16, 2007 20:40
A role of combustion modeling in flow solver? Yoon Main CFD Forum 0 November 26, 2006 13:00
Combustion Modeling and Science Forum MonteCarloPDF_PHDstudent Main CFD Forum 0 July 19, 2005 01:53
Combustion Modeling Pravin Naphade FLUENT 0 May 27, 2004 02:51


All times are GMT -4. The time now is 02:28.