CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

Problem with time average tangential velocity in swirl flow.

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   July 14, 2012, 09:12
Default Problem with time average tangential velocity in swirl flow.
  #1
New Member
 
Join Date: Oct 2010
Posts: 20
Rep Power: 6
lakhi is on a distinguished road
I'm working on the swirl flow and I'm not able to get desired time average tangential velocity. My inlet velocity is 10 m/s and I was expecting tangential velocity to be around 19 m/s (since tangential velocity is 1.7 to 2.5 times the inlet velocity) but I'm getting 11.5 m/s only. In swirl flow velocity is not independent and is coupled to pressure, thus simply time averaging the tangential velocity (as given in FLUENT) is not giving good results, although the nature of tangential velocity is fine. All I need to have is the x-velocity "vx" , the y-velocity "vy" and the z-velocity "vz" . The mean z-velocity "vz" is same as the mean axial velocity "vaxial" . The mean tangential velocity "vθ" is to be obtained using Fluent custom field function:

vθ = vx cos θ + vy sin θ

where "vx" is the time averaged x-velocity, "vy" is the time averaged y-velocity and "θ" is the angular coordinate.

Now when I open Fluent custom field function, nowhere i can find "θ". The above expression tells that the coordinate system used is the Cartesian coordinate system because tangential velocity vθ is expressed in terms of vx and vy. But how to express this "θ". Do I have to write a UDF for this? If yes, how. Suggestions will be appreciated.
lakhi is offline   Reply With Quote

Old   July 14, 2012, 13:38
Default
  #2
Senior Member
 
sbaffini's Avatar
 
Paolo Lampitella
Join Date: Mar 2009
Location: Italy
Posts: 534
Blog Entries: 14
Rep Power: 17
sbaffini will become famous soon enough
cos (theta) = x/r = x / sqrt(x^2 + y^2)

sin (theta) = y/r = y / sqrt(x^2 + y^2)

where theta is measured counterclockwise with respect to the positive x axis.

In this case the formula for v_theta becomes (the one you wrote is for v_r):

v_theta = (x * Vy - y * Vx) / sqrt(x^2 + y^2)

where Vx and Vy are the velocity components along the x and y directions.

While for v_r you get:

v_r = (x * Vx + y * Vy) / sqrt(x^2 + y^2)

Now it's up to you to substitute the correct velocity components and cell center coordinates in a custom field functions (still, i suggest using an UDF to control possible singularities on the axis).

By the way, the statistics on unsteady flows (in general, not only Fluent) are just a postprocessing step. The coupling between pressure and tangential velocity has nothing to do with the correct post-processing or computation.
sbaffini is offline   Reply With Quote

Old   July 15, 2012, 01:13
Default
  #3
New Member
 
Join Date: Oct 2010
Posts: 20
Rep Power: 6
lakhi is on a distinguished road
Thanks sbaffini

I got it n I'll be trying it soon. I still have one question! Is the tangential velocity calculation made by fluent (one of its default option for velocities) different from the one given in your expression?
lakhi is offline   Reply With Quote

Old   July 16, 2012, 17:45
Default
  #4
Senior Member
 
sbaffini's Avatar
 
Paolo Lampitella
Join Date: Mar 2009
Location: Italy
Posts: 534
Blog Entries: 14
Rep Power: 17
sbaffini will become famous soon enough
I don't know this but certainly, if you agree with me on the derivation, it can't be different. What i'm sure of is that the tangential velocity is just a post-processing quantity and not a solved one (except for 2D axysimmetric flows or some rotating frames... but that's another story)
sbaffini is offline   Reply With Quote

Old   July 16, 2012, 23:00
Default
  #5
New Member
 
Join Date: Oct 2010
Posts: 20
Rep Power: 6
lakhi is on a distinguished road
Thanx sbaffini for your reply. Yea you are right. Even fluent uses the same expression for the tangential velocity, which I've confirmed with the one given by you, and the results are the same.
sbaffini, I've one more question. What is the procedure for time averaging of any parameter in the simulation. Shall I start averaging right from the beginning of the simulation or when the simulation is about to converge and let it run for some extra time? I'm following the former one with extra run time.
lakhi is offline   Reply With Quote

Old   July 18, 2012, 16:28
Default
  #6
Senior Member
 
sbaffini's Avatar
 
Paolo Lampitella
Join Date: Mar 2009
Location: Italy
Posts: 534
Blog Entries: 14
Rep Power: 17
sbaffini will become famous soon enough
Forget the CFD case. If you had to make some averages of some quantity varying in time... would you wait for it first reaching a statistically steady state? I think you know the answer (which, just in case, is to wait until the statistically steady state is reached before averaging)
sbaffini is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Problem with FloatingObject Leech OpenFOAM Running, Solving & CFD 10 March 29, 2012 15:24
High Courant Number @ icoFoam Artex85 OpenFOAM Running, Solving & CFD 9 January 3, 2012 09:06
convergence problem when use pisoFoam, LES for wind tunnel case Forrest_Lei OpenFOAM 3 July 19, 2011 06:00
SimpleFoam k and epsilon bounded nedved OpenFOAM Running, Solving & CFD 1 November 25, 2008 21:21
Variables Definition in CFX Solver 5.6 R P CFX 2 October 26, 2004 02:13


All times are GMT -4. The time now is 19:45.